19.2. Using the CutCell Dialog Box

The CutCell dialog box and the commands in the /mesh/cutcell menu enable you to perform various tasks related to generating the CutCell mesh.

You can use Create in the CutCell dialog box to generate the CutCell mesh based on the objects and material points selected.

The generic procedure for generating the CutCell mesh is as follows:

  1. Define the objects.

    1. Right click on Model in the Model Tree and select Object Management... to open the Manage Objects dialog box. See Using the Manage Objects Dialog Box.

    2. Make sure the objects are appropriately defined (see Object Attributes for details).

    3. Create capping surfaces if required (see Patching Tools for details).


    Important:  The objects defined include the corresponding edges that are used for capturing features during the CutCell mesh generation. If you are starting from an earlier setup, you may need to add the appropriate edge zones to the object before proceeding. Several options for creating the Edge Zones are described in Extract Edge Zones.


  2. Define the material points, if needed.

    1. Right click on Model in the Model Tree and select Material Points... to open the Material Points dialog box.

    2. Make sure the material points are appropriately defined (see Creating Material Points for details).

  3. Define the size functions as appropriate (see Defining Size Functions for details).

    1. Right click on Model in the Model Tree and select Functions from the Sizing context menu to open the Size Functions dialog box.

    2. Make sure the size functions are appropriately defined.

  4. Select the objects and material points to be used for the CutCell mesh generation in the CutCell dialog box.

    1. From the Mesh menu, select Cutcell... to open the CutCell dialog box.

    2. Select the appropriate objects in the Objects selection list.

    3. Select the appropriate material points in the Material points selection list.

    4. Enable Keep Solids Cell Zones in the Options group box, if required.

  5. Click Create in the CutCell dialog box.

    The face zones are separated by cell neighbor and normals on face zones connected to the fluid cell zones are oriented into the fluid zone. A face zone group is created for the face zones of each fluid cell zone. Additionally, the defaults for post volume mesh prism generation will be set (see Generating Prisms for the CutCell Mesh for details).

  6. Right click on Model in the Model Tree and select Prepare for Solve.

    Operations such as deleting dead zones, deleting geometry objects, deleting edge zones, removing face/cell zone name prefixes and/or suffixes, deleting unused faces and nodes are performed during the cleanup operation.

  7. Generate prism layers, if required.

    1. Click Create Prisms... to open the Prisms dialog box.

    2. Examine the face zone group created for the face zones of the fluid cell zones and determine the face zones for which prism meshing parameters are to be specified.

    3. Specify the prism meshing parameters as appropriate and click Apply.

    4. Click Create in the Prisms dialog box.

  8. Verify the quality of the CutCell mesh and perform quality improvement operations, if required.


Note:  Use the File > Write > Case... menu item with the Write As Polyhedra option enabled to write the case file in the format that can be read in solution mode in Fluent.



Release 18.2 - © ANSYS, Inc. All rights reserved.