14.2. Using the Auto Mesh Dialog Box

The Auto Mesh dialog box enables you to automatically create the volume mesh using the different mesh elements available. This dialog box can used for generating the volume mesh based on face zones or based on a mesh object and relevant material points. For more detail about object-based mesh generation, refer to Objects.

The generic procedure for using the Auto Mesh dialog box for creating the volume mesh is as follows:

  1. Determine the meshing approach (face zone based or object based) and the mesh elements required for the particular case.

  2. Open the Auto Mesh dialog box using the Mesh > Auto Mesh... menu item or from the context-sensitive menu available by right-clicking on any Mesh Object, or its Cell Zones or Volumetric Regions branch in the Model Tree.

  3. Select the appropriate option in the Object drop-down list in the Auto Identify Volume group box.

    1. For the face zone based meshing approach, ensure that none is selected in the Object drop-down list.

    2. For the object based meshing approach, select the appropriate mesh object in the Object drop-down list. Enable/disable Keep Solid Cell Zones and Keep Dead Cell Zones as required.


      Tip:  If you open the Auto Mesh dialog box from the context-sensitive menu in the Model tree, the Mesh Object is automatically selected.


  4. Select the appropriate option in the Grow Prisms drop-down list in the Boundary Layer Mesh group box.

    1. Retain the default selection of none if you do not need to grow prism layers for the current meshing approach.

    2. Select scoped if you want to specify object-specific prism parameters. Click Set... to open the Scoped Prisms dialog box and define the prism parameters and scope. Refer to Prism Meshing Options for Scoped Prisms for details.

    3. Select zone-specific if you want to specify zone-specific prism parameters. Click Set... to open the Prisms dialog box and specify the zone-specific prism parameters. Refer to Procedure for Creating Zone-based Prisms for details.

  5. Select the appropriate quad-tet transition elements from the Quad Tet Transition list. Click Set... to open the Pyramids dialog box or the Non Conformals dialog box (depending on the selection) and specify the appropriate parameters. Refer to Creating Pyramids and Creating a Non-Conformal Interface for details.

  6. Select the appropriate option from the Volume Fill list. Click Set... to open the Tet, Hexcore, or Poly dialog box (depending on the selection) and specify the appropriate parameters. Refer to Initializing the Tetrahedral Mesh, Refining the Tetrahedral Mesh, Controlling Hexcore Parameters, and Steps for Creating the Polyhedral Mesh for details.


    Note:  The No Fill option is not available for object based volume meshing.


  7. Specify the appropriate Volume Fill Options.

    1. For the Tet or Poly methods, set the following:

      • Select the appropriate option for Cell Sizing.

        • Size Field specifies that the cell size is determined based on the current size-field.

        • Geometric specifies that the cell size in the interior of the domain is obtained by a geometric growth from the closest boundary according to the growth rate specified.

          Set the Growth Rate required.

      • Specify the Max Cell Length. Click Compute to compute the maximum cell size based on the mesh object.

    2. For the Hexcore method, set the following:

      • Select the appropriate option for Type.

        Retain the default selection of Cartesian or select the Octree type.

      • Set the number of Buffer Layers and Peel Layers.

      • Specify the Max Cell Length for the Cartesian approach. Click Compute to compute the maximum cell size based on the mesh object.

        Specify the Min Cell Length for the Octree approach.

  8. For object-based meshing enable Merge Cell Zones within Regions to create a single cell zone within a region, or disable to keep the cell zones separate.

    For zone-based meshing, enable Merge Cell Zones to create a single cell zone within a domain, or disable to keep the cell zones separate.


    Note:  For object-based meshing and parallel processing, after your mesh is distributed, this option is active automatically.


  9. Click Mesh to automatically create the mesh.

Alternatively, you can use the command /mesh/auto-mesh to generate the mesh automatically. Specify a mesh object name for object-based auto mesh; if no name is given, face zone based auto mesh is performed. Specify the mesh elements to be used when prompted. Specify whether to merge the cells into a single zone or keep the cell zones separate. For face zone based meshing, specify whether to automatically identify the domain to be meshed based on the topology information.


Note:  You can specify the meshing parameters for the mesh elements (prisms, pyramids or non-conformals, tet, or hex) using either the respective dialog boxes or the associated text commands prior to using the auto-mesh command.



Release 18.2 - © ANSYS, Inc. All rights reserved.