18.2. Steps for Creating the Polyhedral Mesh

The Auto Mesh dialog box contains options to control the polyhedral volume mesh generation.

You can generate the poly mesh as follows:

  1. Open the Auto Mesh dialog box from the context-sensitive menu available by right-clicking on any mesh object or its Volumetric Regions or Cell Zones branch in the tree.

    You can also use the Mesh > Auto Mesh menu item to open the Auto Mesh dialog box.

  2. Ensure that the mesh object is selected in the Object drop-down list.


    Note:  If you open the Auto Mesh dialog box from the context-sensitive menu in the tree, the Mesh Object to which the cell zones or volumetric regions belong is automatically selected.


  3. Enable/disable the Keep Solid Cell Zones option, as appropriate.

  4. Select the appropriate option in the Grow Prisms drop-down list in the Boundary Layer Mesh group box.

    1. Retain the default selection of none if you do not need to grow prism layers for the current meshing approach.

    2. Select scoped if you want to specify object-based prism controls. Click Set... to open the Scoped Prisms dialog box and define the prism controls for the mesh object. Refer to Prism Meshing Options for Scoped Prisms for details.


      Tip:  You can save your scoped prism controls to a file (*.pzmcontrol) for use in batch mode, or read in a previously saved scoped prism file.



      Note:
      • Poly meshing does not support zone-specific prisms.

      • Stair-stepping will occur in regions of transition between the prism layers and the adjacent tets.


  5. Set the Poly mesh parameters.

    Select the Poly option from the Volume Fill list and set the following Volume Fill Options.

    • Select the appropriate option for Cell Sizing.

      • Size Field specifies that the cell size is determined based on the current size-field.

      • Geometric specifies that the cell size in the interior of the domain is obtained by a geometric growth from the closest boundary according to the growth rate specified.

        Set the Growth Rate required.

    • Specify the Max Cell Length. Click Compute to compute the maximum cell size based on the mesh object.


    Note:  You can also set these parameters in the Poly dialog box.


    Click the Set... button to open the Poly dialog box.

    1. Select the options in the Options group box.

      The Merge Free Nodes, Delete Unused Nodes, and Improve Poly Mesh options are enabled by default. You can also include improving the surface mesh by enabling the Improve Surface Mesh option.

    2. Specify an appropriate value for Feature Angle. This sets the threshold for preserving features. The default setting is 30 degrees.

    3. Select the appropriate cell zone type from the Non-Fluid Type list in the Poly Zones group box.


      Note:  Dead cell zones will be automatically deleted after the mesh is initialized.


      When the initial mesh is generated, all the cells are grouped into contiguous zones separated by boundaries. The mesh is considered to contain a single fluid zone and one or more dead regions. The zone just inside the outer boundary is set to be active and is labeled a fluid zone. All other non-fluid zones will be inactive. Only active zones will be considered for refinement during the mesh generation process.


      Note:  Volume region type is used to determine the cell zone type.


      You can refine different groups of zones using different refinement parameters for each group by toggling the zones between active and inactive. If however, you need to use the same refinement parameters for all the zones, you can change the specification of Non-Fluid Type to a type other than dead (for example, solid). When the Non-Fluid Type is set to a type other than dead, all the zones will be activated after initialization. Hence, you can set the appropriate refinement parameters without setting all the zones to be active.

    4. In most cases, the default node spacing threshold should be acceptable. If you want to change it, click Controls to open the Poly Init Controls dialog box where you can modify the value.

    5. Set poly cell growth parameters using the options in the Cell Size group box. Specify appropriate values for Max Cell Volume and Growth Rate. You can use the Compute button to determine the maximum cell size based on the size field.

      Ensure that cells in the interior are not larger than the size required by selecting the appropriate option in the Cell Sizing list:

      geometric

      specifies that the cell size in the interior of the domain is obtained by a geometric growth from the closest boundary according to the growth rate specified.

      size-field

      specifies that the cell size is determined based on the current size-field.

    6. Click the Local Regions button to access the Tet Refinement Region dialog box, where you can setup and activate local tetrahedral refinement regions. These regions are used during the initial tetrahedral mesh generation; they are not directly applicable to the poly mesh. The number of activated regions will be reported in the Message field.

  6. Return to the Auto Mesh dialog box and enable or disable additional Options as desired.

    1. Enable Merge Cell Zones within Regions to create a single cell zone within a region, or disable to keep the cell zones separate.

  7. Click Mesh in the Auto Mesh dialog box.


Release 18.2 - © ANSYS, Inc. All rights reserved.