16.3.1. Initializing Using the Tet Dialog Box

You can use Mesh > Tet to initialize the mesh using the options available in the Initialization tab of the Tet dialog box.

  1. Select the appropriate actions to be performed during initialization from the Options group box.

    The Merge Free Nodes and Delete Unused Nodes options are enabled by default. You can also include improving the surface mesh in the mesh initialization process by enabling the Improve Surface Mesh option.

  2. Select the appropriate option from the Non-Fluid Type drop-down list. Enable Delete Dead Zones, if required.

    When the initial mesh is generated, all the cells are grouped into contiguous zones separated by boundaries. The mesh is considered to contain a single fluid zone and one or more dead regions. The zone just inside the outer boundary is set to be active and is labeled a fluid zone. All other non-fluid zones will be inactive. Only active zones will be considered for refinement during the mesh generation process.


    Note:  For zone-based meshing, if any cell zone has at least one boundary zone type as inlet, it will automatically be set to fluid type. For object based meshing, volume region type is used to determine the cell zone type.


    You can refine different groups of zones using different refinement parameters for each group by toggling the zones between active and inactive. If however, you need to use the same refinement parameters for all the zones, you can change the specification of Non-Fluid Type to a type other than dead (for example, solid). When the Non-Fluid Type is set to a type other than dead, all the zones will be activated after initialization. Hence, you can set the appropriate refinement parameters without setting all the zones to be active.

  3. Specify additional initialization parameters, if required. These parameters are available in the Tet Init Controls dialog box. Click the Controls... button to open the Tet Init Controls dialog box.

  4. Click Init to initialize the mesh.

    A Working dialog box will appear, informing you that the initialization is in progress. Click the Cancel button in the Working dialog box to abort the mesh initialization process. Canceling the initialization will leave the mesh incomplete.

    • If you try to initialize the mesh after canceling an initial attempt, a dialog box will ask if it is OK to clear the incomplete mesh.

      After you approve, the initialization process will begin again.

    • If you try to initialize the mesh when duplicate nodes exist, the initialization will fail. You must clear the mesh and merge the duplicate nodes before attempting the initialization again.

    • If you try to initialize the mesh when a volume mesh already exists, a Question dialog box will appear, asking if you want to clear the existing mesh. If you click Yes, the volume mesh will be cleared and then the mesh will be initialized. If you click No, the operation will be canceled.

    • If you need to preserve the existing mesh during the meshing process, use the command /mesh/tet/preserve-cell-zone to specify the cell zones to be preserved and click the Init button to proceed with the initialization.

    • If the initial mesh generation fails, check the validity of the surface mesh. In some rare cases, you may need to change the sliver size parameter (by using the Tet dialog box).

    Refer to Common Tetrahedral Meshing Problems for more information on meshing problems.


Release 18.2 - © ANSYS, Inc. All rights reserved.