11.3.1. Meshing All Regions Collectively Using Auto Mesh

The Auto Mesh dialog box contains options for generating the volume mesh for all computed volumetric regions of the mesh object.

The volume mesh can be generated as follows:

  1. Open the Auto Mesh dialog box from the context-sensitive menu available by right-clicking on any mesh object or its Volumetric Regions or Cell Zones branch in the tree.

    You can also use the Mesh > Auto Mesh menu item to open the Auto Mesh dialog box.

  2. Ensure that the mesh object is selected in the Object drop-down list.


    Note:  If you open the Auto Mesh dialog box from the context-sensitive menu in the tree, the mesh object to which the cell zones, or volumetric regions, belong is automatically selected.


  3. Enable/disable Keep Solid Cell Zones and Keep Dead Cell Zones, as required.

  4. Select the appropriate option in the Grow Prisms drop-down list in the Boundary Layer Mesh group box.

    1. Retain the default selection of none if you do not need to grow prism layers for the current meshing approach.

    2. Select scoped if you want to specify object-based prism controls. Click Set... to open the Scoped Prisms dialog box and define the prism controls for the mesh object. Refer to Prism Meshing Options for Scoped Prisms for details.


      Tip:  You can save your scoped prism controls to a file (*.pzmcontrol) for use in batch mode, or read in a previously saved scoped prism file.


    3. Select zone-specific if you want to specify zone-specific prism parameters. Click Set... to open the Prisms dialog box and specify the zone-specific prism parameters. Refer to Procedure for Creating Zone-based Prisms for details.


      Note:  Poly meshing does not support zone-specific prisms.


  5. Select the appropriate quad-tet transition elements from the Quad Tet Transition list. Click the Set... button to open the Pyramids dialog box or the Non Conformals dialog box (depending on the selection) and specify the appropriate parameters. Refer to Creating Pyramids and Creating a Non-Conformal Interface for details.


    Note:  The Quad Tet Transition options are not applicable to poly mesh.


  6. Select the appropriate option from the Volume Fill list. Click the Set... button to open the Tet, Hexcore, or Poly dialog box (depending on the selection). Specify the appropriate parameters. Refer to Initializing the Tetrahedral Mesh, Refining the Tetrahedral Mesh, Controlling Hexcore Parameters, and Generating Polyhedral Meshes for details.


    Note:
    • The No Fill option is not available when a mesh object is selected for volume meshing.

    • Some operations such as prisms generation only, Tet-initialization only, Hexcore only, are not available for object-based volume meshing. Similarly, options under the Zones group in the Tet and Hexcore dialog boxes, that require a zone-based workflow, have no effect for object-based volume meshing.


  7. Specify the appropriate Volume Fill Options.

    1. For the Tet or Poly methods, set the following:

      • Select the appropriate option for Cell Sizing.

        • Size Field specifies that the cell size is determined based on the current size-field.

        • Geometric specifies that the cell size in the interior of the domain is obtained by a geometric growth from the closest boundary according to the growth rate specified.

          Set the Growth Rate required.

      • Specify the Max Cell Length. Click Compute to compute the maximum cell size based on the mesh object.

    2. For the Hexcore method, set the following:

      • Select the appropriate option for Type.

        Retain the default selection of Cartesian or select the Octree type.

      • Set the number of Buffer Layers and Peel Layers.

      • Specify the Max Cell Length for the Cartesian approach. Click Compute to compute the maximum cell size based on the mesh object.

        Specify the Min Cell Length for the Octree approach.

  8. Enable or disable additional Options as desired.

    1. Enable Merge Cell Zones within Regions to create a single cell zone within a region, or disable to keep the cell zones separate.

  9. Click Mesh in the Auto Mesh dialog box.

Alternatively, you can use the command /mesh/auto-mesh to generate the mesh automatically. Specify a mesh object name for object-based auto mesh; if no name is given, face zone based auto mesh is performed. Specify the mesh elements to be used when prompted. Specify whether to merge the cells into a single zone or keep the cell zones separate. For face zone based meshing, specify whether to automatically identify the domain to be meshed based on the topology information.


Note:  You can specify the meshing parameters for the mesh elements (prisms, pyramids or non-conformals, tet, or hex) using either the respective dialog boxes or the associated text commands prior to using the auto-mesh command. Commands for poly meshes are located under the mesh/poly menu.



Release 18.2 - © ANSYS, Inc. All rights reserved.