10.1. Surface Mesh Processes

In principal, there are two basic workflows to create a conformal, connected surface mesh from an unconnected assembly.


Note:  It is assumed that objects are already created upon CAD import. Object management, if necessary, is described in Objects.


Single fluid volume using Wrapper based workflow

The basic Wrapper based workflow for a single fluid volume simulation follows these steps:

  1. Import the CAD model using the CAD Faceting tessellation option.

    Geometry objects are created. See Importing CAD Files for additional information.

  2. Define sizing and compute the size field.

    Scoped Sizing is recommended to apply individual size controls on specific objects as required. See Defining Scoped Sizing Controls for additional information.

  3. Define material points to assist in identifying the fluid volume.

    See Material Points for additional information.

  4. Check and fix the geometry, particularly gaps.

    You can use the context menu Diagnostics > Geometry, accessible from any Geometry object, to assist in finding any geometry issues. See Diagnostic Tools for additional information.

    Missing geometry objects may be constructed as described in Preparing the Geometry.

  5. Define periodic boundaries, if applicable.

    See Creating Periodic Boundaries for additional information.

  6. Wrap the model.

    Step through the options available in the Wrap context menu. See The Wrapping Process for details.

  7. Check the mesh and improve the quality, if necessary.

    You can use the context menu Diagnostics > Connectivity and Quality, accessible from any mesh object.

Complex topology using Join and Intersect based workflow

The basic Join/intersect based workflow for complex topology such as CHT simulation, follow these steps:

  1. Import the CAD model using the CFD Surface Mesh tesselation option.

    Mesh objects are created. See Importing CAD Files for additional information.


    Note:  If the assembly has already been connected (for example, using Share Topology operations in ANSYS DesignModeler or SpaceClaim), it is sufficient to just import the CAD using the One object per file and CFD Surface Mesh options.


  2. Check the mesh and fix the connectivity, if necessary.

    You can use the context menu Diagnostics > Connectivity and Quality, accessible from any mesh object.

  3. Check and fix the geometry, particularly gaps.

    You can use the context menu Diagnostics > Geometry, accessible from any Geometry object, to assist in finding any geometry issues. See Diagnostic Tools for additional information.

    Missing geometry objects may be constructed as described in Preparing the Geometry.

  4. Merge all objects to a single object using the Merge option in the context menu.

  5. Connect all bodies.

    You can use the Join/Intersect context menu or the onscreen tools for Join or Intersect. See Connecting Objects for additional information.

  6. Optionally define sizing, compute the size field and remesh if necessary.

    Remesh is recommended as it often reduces mesh count and improves quality while maintaining sufficient mesh density. You can use the Remesh Faces context menu or the onscreen tools.

    Computing a size field is necessary only if you choose to remesh. Scoped Sizing is recommended to apply individual size controls on specific objects as required. See Defining Scoped Sizing Controls for additional information.

  7. Define periodic boundaries, if applicable.

    See Creating Periodic Boundaries for additional information.

  8. Check the mesh and improve the quality, if necessary.

    You can use the context menu Diagnostics > Connectivity and Quality, accessible from any mesh object.

When the surface mesh is conformally connected and of sufficient quality, proceed to generate the volume mesh as described in Object-Based Volume Meshing.


Release 18.2 - © ANSYS, Inc. All rights reserved.