Following is the general process for performing a 2-D to 3-D analysis:
Determine the load step and substep in the 2-D model at which extrusion should occur.
Initiate the 2-D to 3-D analysis process.
Extrude the 2-D mesh and generate contact elements (if any) on the new 3-D domain.
| Optional: After the extrusion, you can manually add new contact pairs if necessary. |
Map boundary conditions and loads from the 2-D mesh to the new 3-D mesh.
Map solution variables from the 2-D mesh to the new 3-D mesh and rebalance the mapped solutions (if specified).
Continue as a 3-D analysis via a multiframe restart.
Note: Although the preferred method for continuing the 3-D analysis is via a multiframe restart, you can instead initiate a new analysis using the 2-D solution as the initial state, requiring the following:
The initial-state values saved after Step 5 (INISTATE,WRITE).
The .cdb file that includes the 3-D mesh.
Some deformation history variables may not be available in the .ist file. It may be necessary to include a dummy load step to achieve equilibrium before adding new loads.
Because the entire 2-D mesh is used for the extrusion process, only one MAP2DTO3D command block can be issued at a given loadstep and substep.
The following topics provide more general information about the 2-D to 3-D analysis process:
The following flowchart illustrates the general 2-D to 3-D analysis process:
For information about the commands shown in the flowchart, see Key Commands Used in a 2-D to 3-D Analysis .
Following is a description of the key commands used in a 2-D to 3-D analysis:
| Command | Description | 2-D to 3-D Analysis Comments |
|---|---|---|
| /CLEAR,NOSTART | Clears the database | Always clear the database before reentering the solution processor (/SOLU) and initiating the 2-D to 3-D analysis process. |
| MAP2DTO3D,START |
Initiates the 2-D to 3-D analysis | When you initiate a 2-D to 3-D analysis, the program verifies
that the necessary files (.rdb,
.rst,
.rxxx, and
.ldhi) exist for the specified substep and
rebuilds the data environment at that substep. All nodes are updated to the deformed geometry in preparation for extrusion. |
| EEXTRUDE |
Extrudes the 2-D mesh to a 3-D mesh and regenerates contact pairs on the 3-D model if necessary. After extrusion, you can manually add new contact pairs which have not yet contacted, if necessary. Some limitations apply for rigid-to-flexible contact pairs. |
The entire 2-D mesh is selected automatically for extrusion. Partial mesh extrusion is not supported. This command also controls how boundary-condition and load mapping occurs. Depending on the arguments specified for this command, some or all of the new nodes may be rotated to local nodal coordinate systems. |
| MAP2DTO3D,FINISH | Maps the loads, temperatures, and boundary conditions from the 2-D mesh to the corresponding 3-D mesh. | Equivalent boundaries and loads on the 3-D model are generated. If necessary, you can control how the equivalent loads and constraints are generated (EEXTRUDE). |
| MAP2DTO3D,SOLVE | Maps node and element solutions and rebalance the results. | Maps the solved nodal and element solutions from the 2-D deformed mesh to the newly extruded 3-D mesh and rebalances the mapped solution results through equilibrium. |
Continue with your analysis of the 3-D model via a multiframe restart (or by starting a new 3-D analysis using the 2-D solution as the initial state).