4.2. Requirements for a 2-D to 3-D Analysis

All multiframe restart files must be available.

Following are the 2-D elements and the materials, loads, and boundary conditions that can be used for 2-D to 3-D analysis:

Support CategoryRequirements

Solid elements

Reinforcing elements

Contact elements

  • TARGE169

  • CONTA171 and CONTA172 with any of the following valid KEYOPT settings:

    KEYOPT (1) = 0
    KEYOPT (2) = 0, 1, 3, 4
    KEYOPT (3) = 0
    KEYOPT (4) = 0, 1, 2, 3
    KEYOPT (5) = 0, 1, 2, 3, 4
    KEYOPT (7) = 0, 1, 2, 3
    KEYOPT (8) = 0
    KEYOPT (9) = 0, 1, 2, 3, 4
    KEYOPT (10) = 0, 2
    KEYOPT (11) = 0
    KEYOPT (12) = 0, 1, 2, 3, 4, 5, 6
    KEYOPT(14) = 0
  • TARGE170

  • CONTA173 and CONTA174 with any of the following valid KEYOPT settings:

    KEYOPT (1) = 0
    KEYOPT (2) = 0, 1
    KEYOPT (4) = 0, 2, 3
    KEYOPT (5) = 0, 1, 2, 3, 4
    KEYOPT (7) = 0, 1, 2, 3
    KEYOPT (8) = 0
    KEYOPT (9) = 0, 1, 2, 3, 4
    KEYOPT (10) = 0, 2
    KEYOPT (11) = 0
    KEYOPT (12) = 0, 1, 2, 3, 4, 5, 6
    KEYOPT(14) = 0

Contact pair behavior [3]

  • Rigid-to-flexible [2]

  • Flexible-to-flexible

  • Self-contact

Materials

  • Most structural materials. [4] [5]

Analysis types
  • Static analysis with geometric nonlinearity (NLGEOM,ON).

Loads and boundary conditions (BCs)

  • Displacements, forces, pressures, and nodal temperatures (BF,TEMP). [6]

  • Tabular displacements. [7]

  • Tabular pressures that are functions of time only. [7]

  • Fluid-penetration loads applied to contact elements (SF or SFE). [7] [8]

Files
  • .rdb, .rst, .ldhi, .ist, and .cdb.

  1. Axisymmetric (with or without torsion) and plane strain states of stress only. (For PLANE182, enhanced strain formulation is not supported.)

  2. 2-D target elements (line) are extruded in 3-D as tangent planes or as annuli in axisymmetric extrusion. The extrusion is always planar in plane strain extrusion.

  3. Pilot nodes in 2-D are retained as pilot nodes in 3-D.

  4. Exceptions are: CAST (cast iron), CDM (Mullins effect), CONCR (concrete), CZM (cohesive zone), DMGE and DMGI (damage), MPLANE (microplane), SMA (shape memory alloy), and SWELL (swelling).

  5. For materials associated with user-defined state variables (TB,STATE), it may be necessary to issue the MAPVAR command. The defined size of state variables must be such that full 3-D descriptions of stress and strain tensors can be accommodated (that is, the defined stress and strain tensors must be able to possess six independent components).

  6. Loads applied on surface-effect elements (such as SURF153) are not supported.

  7. The axisymmetric option with torsion is not supported.

  8. CONTA171, CONTA172, CONTA173, and CONTA174.

The EEXTRUDE command documentation shows the topological mapping of 2-D elements (solid, contact, and target) into specific 3-D elements.


Release 18.2 - © ANSYS, Inc. All rights reserved.