2.2. Rezoning Requirements

Rezoning is available for 2-D and 3-D analyses. All multiframe restart files must be available.

Following are the supported analysis types, elements, materials, loads, boundary conditions, and other rezoning requirements:

Support Category Support Details

Solid elements

Contact elements

  • Pair-based contact only. [5]

  • TARGE169

  • CONTA171 and CONTA172 with any of the following valid KEYOPT settings:

    KEYOPT (1) = 0
    KEYOPT (2) = 0, 1, 3, 4
    KEYOPT (3) = 0
    KEYOPT (4) = 0, 1, 2, 3
    KEYOPT (4) = 0, 1, 2
    KEYOPT (5) = 0, 1, 2, 3, 4
    KEYOPT (7) = 0, 1, 2, 3
    KEYOPT (8) = 0
    KEYOPT (9) = 0, 1, 2, 3, 4
    KEYOPT (10) = 0, 2
    KEYOPT (11) = 0
    KEYOPT (12) = 0, 1, 2, 3, 4, 5, 6
    KEYOPT(14) = 0
  • TARGE170

  • CONTA173 and CONTA174 with any of the following valid KEYOPT settings:

    KEYOPT (1) = 0
    KEYOPT (2) = 0, 1
    KEYOPT (4) = 0, 2, 3
    KEYOPT (5) = 0, 1, 2, 3, 4
    KEYOPT (7) = 0, 1, 2, 3
    KEYOPT (8) = 0
    KEYOPT (9) = 0, 1, 2, 3, 4
    KEYOPT (10) = 0, 2
    KEYOPT (11) = 0
    KEYOPT (12) = 0, 1, 2, 3, 4, 5, 6
    KEYOPT(14) = 0

Contact pair behavior

  • Rigid-flexible [6]

  • Flexible-flexible

  • Self-contact

Surface-effect elements

Materials

  • Most structural material models. [8]

Analysis types
  • Static analysis with geometric nonlinearity (NLGEOM,ON).

Loads and boundary conditions (BCs) [10]

  • Displacements, forces, pressures, and nodal temperatures (BF,TEMP).

  • Tabular displacements, forces, and pressures that are functions of time only.

  • Fluid-penetration loads applied to contact elements (SF or SFE). [9]

Region to be remeshed [13]
  • The selected nodes inside the region must have the same nodal coordinate system.

  • Boundary nodes can have different nodal coordinate systems.

  • Elements must be of the same element type, material, element coordinate system, and real constant.

  • If two regions with different attributes require remeshing, you must remesh the regions separately. [11]

  • Node and element components defined in remesh regions are lost during remeshing. [12]

Files
  • .rst, .rdb, .rdnn , .rxxx (where xxx is the substep in which rezoning is initiated), .ldhi, and .cdb.

  1. B-bar method only (KEYOPT(1) = 0).

  2. All stress states (KEYOPT(3)) are supported: plane strain, plane stress, axisymmetric, and generalized plane strain. Pure displacement formulation (KEYOPT(6) = 0) or mixed u-P formulation (KEYOPT(6) = 1) is supported.

  3. Pure displacement formulation (KEYOPT(6) = 0) or mixed u-P formulation (KEYOPT(6) = 1) is supported in a nonlayered configuration (KEYOPT(3) = 0).

  4. Works with REMESH,READ only.

  5. General contact is not supported.

  6. Target elements and pilot node cannot be remeshed.

  7. Only normal and tangential pressures applied on SURF153 and SURF154 are supported. (That is, rezoning support is available only for pressure on faces 1 and 2 for SURF153 and pressure on faces 1, 2 and 3 for SURF154.)

  8. Exceptions are: CAST (cast iron), CDM (Mullins Effect), CONCR (concrete), CZM (cohesive zone), DMGE and DMGI (damage), MPLANE (microplane), SMA (shape memory alloy), SWELL (swelling). For materials associated with user-defined state variables (TB,STATE), it may be necessary to issue the MAPVAR command.

  9. CONTA171, CONTA172, CONTA173, CONTA174.

  10. Do not remove nodal constraints (DDELE) during solution before rezoning or remeshing.

  11. For more information, see Hints for Remeshing Multiple Regions .

  12. Node and element components associated with nonlinear adaptivity criteria are preserved.

  13. Nonlinear stabilization is not supported.

The conditions specified apply only to the region to be remeshed. No limitations exist for other regions, although the analysis type itself must support rezoning.


Release 18.2 - © ANSYS, Inc. All rights reserved.