1.1. Harmonic Sweep Using VT Accelerator

The harmonic sweep feature of VT Accelerator provides a high-performance solution for a structural analysis where the material properties are frequency-dependent and no modal responses can be used.

The harmonic sweep feature of VT Accelerator completes one normal ANSYS run at the mid-frequency of the specified frequency range.

The harmonic sweep interpolates the stiffness, damping, mass, and loading on the whole range to give an approximation of the results across the frequency range. The harmonic sweep evaluates these values for different frequencies (between 2 and 6) across the frequency range, and then it computes a polynomial approximation of the values.

The harmonic sweep performs accurate approximations of the results across the frequency range in user-specified steps.

If the loading, material properties, or real constants defined with a data table (BF ,TBFIELD command, or COMBIN14) are frequency-dependent and too few data points exist in the table, the polynomial interpolation of the values will be poor. In case of abrupt variations for a given frequency f2, ANSYS, Inc. recommends splitting the frequency range [f1 f3] into two ranges (e.g., [f1 f2] ; [f2 f3] ) and performing separate analyses on each range.

The following Variational Technology topics are available for harmonic sweep:

1.1.1. Structural Elements Supporting Frequency-Dependent Properties

Frequency-dependent property structural elements can be used with the following elements:

ElementFrequency-Dependent Material Properties (defined using TB,ELAS and TB,SDAMP,,,,STRU commands)
PLANE182EX, STRU
PLANE183EX, STRU
SOLID185EX, STRU
SOLID186EX, STRU
SOLID187EX, STRU
SOLID272EX, STRU
SOLID273EX, STRU
SOLID285EX, STRU

1.1.2. Harmonic Sweep for Structural Analysis with Frequency-Dependent Material Properties

The harmonic sweep feature of the VT Accelerator module allows you to define the material elastic properties as frequency-dependent and efficiently compute the frequency response over an entire frequency range. For more information, see the documentation for the TB,ELAS and TB,SDAMP,,,,STRU commands. To use this formulation, use the hysteretic damping formulation with the HROPT command.

If you define the damping ratio (TB,SDAMP,,,,STRU) as a linear function of the frequency, the damping exhibits behavior similar to that of viscous damping. See the Mechanical APDL Theory Reference for more information about the hysteretic and structural damping formulations.

Limitations

  • The frequency-dependent tables (defined by the TB,ELAS and TB,SDAMP commands) define piecewise linear functions. These are used to define the stiffness and damping matrices, which in turn are fitted with a polynomial over the entire frequency range to compute their derivatives as a function of frequency; therefore, if the piecewise linear approximation of the material properties is too coarse, the results will be poor.

1.1.2.1. Beam Example

Consider a cantilever beam, with a Young's modulus of 20e6 psi for static condictions and 30e6 for 500Hz.

ETYPE=186
LF = 10               ! STARTING FREQUENCY
UF = 500              ! ENDING FREQUENCY
N = 50                   ! NUMBER OF SUBSTEP
/PREP7
!*
ET,1,ETYPE
/com, * ==============================================
/com, *
/com, *    Frequency dependent material properties
/com, *
/com, * ==============================================
TB,ELASTIC,1,,2        ! Elastic data table
TBFIELD , FREQ,1 ! First frequency value
TBDATA,1,20e6,0.3 ! E and m
TBFIELD ,FREQ,500 ! Fifth frequency value
TBDATA,1,30e6,0.3
TB,SDAMP,1, ,1        ! damping data table
TBFIELD , FREQ,1 ! First frequency value
TBDATA,1, 0.02        ! Damping co.
TBFIELD ,FREQ,500     ! Fifth frequency value
TBDATA,1, 0.01
MP,DENS,1,.10
BLOCK,0,10,0,2,0,2
LSEL,S,LOC,X,-.5,0.5
LESIZE,ALL,,,2
LSEL,S,LOC,X,9.5,10.5
LESIZE,ALL,,,2
LSEL,S,LOC,X,2,8
LESIZE,ALL,,,5
VMESH,ALL
FINISH
/SOL
LSEL,S,LOC,X,-.5,0.5
DL,all,,all
KSEL,S,LOC,X,8,12
KSEL,R,LOC,Y,-.5,.5
FK,ALL,FY,1000
ASEL,S,LOC,Y,1.8,2.2
SFA,ALL,,PRES,1000,
allsel
FINI
/com, * ==============================================
/com, *
/com, *             VT Harmonic Analysis 
/com, *
/com, * ==============================================
/SOLU
ANTY,HARM
HROUT,OFF                 ! Print complex displacements as amplitude and phase angle
KBC,1
HROPT,VT,,,,HYST
harfrq,LF,UF
nsubst,N
Solve
FINISH
/post26
nsol,10,57,u,y,d1
prvar,10

The following figure shows the difference in the Y displacement at the end of the beam, taking constant material properties for 0Hz, constant properties for 500 Hz, and variable properties:

Figure 1.1:  Y-Displacement Difference at End of Beam

Y-Displacement Difference at End of Beam

Because of the frequency step used to create the frequency response, the first peak is higher on the variable curve than the other two.


Release 18.2 - © ANSYS, Inc. All rights reserved.