5.2. Initial-State Application

This section provides typical cases for applying an initial state, as follows:

5.2.1. Initial Stress Application

Although initial stress is element-based, the structure of the INISTATE command is element-type-independent.

For continuum or link elements, apply initial stress according to the specific element integration point.

For layered elements, apply initial stress based on the layer number, the layer integration point or the element integration point. Beams allow you to apply initial stress based on the cell number, the section integration point, and/or the element integration point.

For reinforced elements, you can assign different values of initial stress to different reinforcings within the same element.

For coupled-field elements CPT212, CPT213, CPT215, CPT216, and CPT217, the initial stresses to be applied are Biot’s effective stress. They are automatically written out when the output stress option is specified (INISTATE, WRITE, , , , , ,S).

The following example input shows how initial stress can be applied in such cases:

Constant Initial Stress on the Whole Model
inistate,defi,,,,,100,200,300,400,500,600

Apply Constant Stress of SX=100 On Beam Element 1
inistate,defi,1,,,,100

Apply a Stress of SX=33.333 at Elem Integration Pt 3 within Element 2
inistate,defi,2,3,,,33.3333	

Apply Constant Stress Of SX=200 in Cell 2 For All Selected Beam Elements
inistate,defi,,,2,,200

Apply Constant Stress Of SX=200 For All Beams In A Model
And Wherever There Is Material=3
inistate,set,mat,3
inistate,defi,,,,,200

Apply a Stress of SX=100,SY=200,SXY=150 for Layers 1,3,5 and
SX=200,SY=0 for Layers 2,4,6 in a Layered Shell Element. Layer
1,3,5 have material 1 and Layer 2,4,6 have material 2.
inistate,defi,,,1,,100,200,150
inistate,defi,,,2,,200
inistate,defi,,,3,,100,200,150
inistate,defi,,,4,,200
inistate,defi,,,5,,100,200,150
inistate,defi,,,6,,200
		OR
inistate,set,mat,1
inistate,defi,,,,,100,200,150
inistate,set,mat,2
inistate,defi,,,,,200 

Apply a Stress of SX=33.333 at Reinf 1 for all elements
inistate,defi,,,1,,33.3333

Also see Example: Initial Stress (IST File) and Example: Initial Stress (INISTATE Command).

5.2.2. Initial Strain Application

The initial stress application example can be extended for initial strain by simply changing the data type to EPEL, as shown:

! Constant Initial Strain on the Whole Model
inistate,set,dtyp,epel
inistate,defi,,,,,0.1,-0.01,-0.01
 
!Apply a Constant Strain of EPEL X=0.01 On Beam Element 1
inistate,set,dtyp,epel
inistate,defi,1,,,,0.01
 
!Apply a Strain of EPEL X=0.01 at Elem Integration Pt 3 within Element 2
inistate,set,dtyp,epel
inistate,defi,2,3,,,0.01
 
!Apply a Constant Strain Of EPEL X = 1E-6 in Cell 2 For All Selected Beam Elements
inistate,set,dtyp,epel
inistate,defi,,,2,,1E-6
 
!Apply a Constant Strain Of EPEL X=1E-3 For All Beams In A Model
!And Wherever There Is Material=3
inistate,set,dtyp,epel
inistate,set,mat,3
inistate,defi,,,,,1E-3
 
! Apply EPS X = 0.1, EPS Y = -0.02, EPS Z = -0.02, for Layers 1,3,5 and
! EPS X = 0.2, for Layers 2,4,6 
! Layer 1,3,5 have material 1 and Layer 2,4,6 have material 2.
inistate,set,mat,1
inistate,defi,,,,,0.1,-0.02,-0.02
inistate,set,mat,2
inistate,defi,,,,,0.2

Also see Example: Initial Strain.

5.2.3. Initial Plastic Strain Application

The initial stress application example can be extended for initial plastic strain by simply changing the data type to EPPL, as shown:

! Constant Initial Plastic Strain and Stress on the Whole Model
inistate,set,dtyp,eppl
inistate,defi,,,,,0.1
inistate,set,dtype,s
inistate,defi,,,,,1000
 
! Apply a Strain of EPEL X=0.01 at Elem Integration Pt 3 within Element 2.
! Here it is assumed that the initial stress is zero.
inistate,set,dtyp,eppl
inistate,defi,2,3,,,0.01

! Apply accumulated equivalent plastic strain.
inistate,set,dtyp,pleq
inistate,defi,2,3,,,0.02
 
! Apply EPS X = 0.1, EPS Y = -0.02, EPS Z = -0.02, for Layers 1,3,5 and
! EPS X = 0.2, for Layers 2,4,6 
! Layer 1,3,5 have material 1 and Layer 2,4,6 have material 2.
inistate,set,dtype,eppl
inistate,set,mat,1
inistate,defi,,,,,2.0
inistate,set,mat,2
inistate,defi,,,,,0.2

Also see Example: Initial Plastic Strain.

5.2.4. Initial Creep Strain Application

The initial stress application example can be extended for initial creep strain by simply changing the data type to EPCR, as shown:

! Apply creep strain, plastic strain, accumulated equivalent plastic strain, stress on 
! all the selected elements
inistate,set,dtyp,epcr
inistate,defi,,,,,0.005
inistate,set,dtyp,eppl
inistate,defi,,,,,0.1
inistate,set,dtyp,epeq
inistate,defi,,,,,0.02
inistate,set,dtype,s
inistate,defi,,,,,1000

Also see Example: Initial Creep Strain.

5.2.5. Initial State with State Variables Application

To use the initial-state capability with state variables via the INISTATE command, simply change the data type to SVAR, as shown:

! Apply initial state – state variables.
! This fictitious svar example contains 7 components: 
!   The 1st component is accumulated equivalent plastic strain.
!   Components 2-7 are plastic strains values.
! at all the selected elements

inistate,set,dtyp,svar
inistate,defi,,,,,0.005,0.1,-0.02,0.02,0,0,0

The INISTATE command does not consider the coordinate systems of quantities stored within the state variables. It is therefore your responsibility to account for the transformations.

Also see Example: Initial Plastic Strain with State Variables .

5.2.6. Node-Based Initial Strain Application

As shown below, a node-based initial state can be applied to all nodes or to a selected subset of nodes. Layer numbers can also be specified.

! Enable Node-Based Initial State
inis,set,node,1
! Apply elastic strains at all nodes in layer 1 and 3
inistate,set,dtyp,epel
inistate,defi,all,,1,,0.005
inistate,defi,all,,3,,0.005
! Apply a different elastic strain at all nodes in layer 2
inistate,defi,all,,2,,0.010
! Apply zero elastic strain at node 10
inistate,defi,10,,all,,0.000
! Apply zero elastic strain at node selection
nsel,s,loc,x,0
inistate,defi,all,,all,,0.000

Also see Example: Node-Based Initial Strain.

5.2.7. Initial Pore Pressure and Void Ratio Application

Initial pore pressure and void ratio are available for coupled pore-pressure-thermal elements (CPTnnn). Apply initial pore pressurel and void ratio on CPTnnn elements by changing the data type to PPRE and VOID, respectively.

! Apply to all the selected elements
porepr=69
inistate,set,dtyp,ppre
inistate,defi,,,,,porepr

! Apply to all the selected elements
vratio=0.4
inistate,set,dtyp,void
inistate,defi,,,,,vratio

Also see Example: Initial Pore Pressure and Void Ratio.

5.2.8. Initial Degree of Saturation and Relative Permeability Application

Initial degree of saturation and relative permeability are available for coupled pore-pressure-thermal elements (CPTnnn). Apply initial degree of saturation and relative permeability on CPTnnn elements by changing the data type to DSAT and RPER, respectively.

Example 5.1:  Applying Initial Degree of Saturation and Relative Permeability
! Apply to all the selected elements
init_sw=0.9
inistate,set,dtyp,dsat
inistate,defi,all,,,,init_sw
init_kr=0.87
inistate,set,dtyp,rper
inistate,defi,all,,,,init_kr

Also see Example: Initial Degree of Saturation and Relative Permeability.

5.2.9. Function-Based Initial State

Function-based initial state is a method for applying data as a function of internal variables. Three options are available: a linear function in X coordinates (LINX), a linear function in Y coordinates (LINX), or a linear function in Z coordinates. The method is available for both node-based and element integration-point-based initial state.

The coordinates used to evaluate the value at a given location are based on initial coordinates in the load step. For user-defined field variables, the coordinates are the initial ones queried via the NLIST (or *GET) command. For a rezoning or linear perturbation model (or after issuing an UPGEOM command after a load step) where the coordinates change, the coordinates used in the subsequent load step are the updated coordinates (which become the initial coordinates for the current load step). As before, the coordinates used can be queried if necessary (NLIST or *GET). For other non-user-defined field variables (such as initial stress or strain), function-based initial state is evaluated only at the first substep in the first load step, and only the initial coordinates are used.

For higher-order elements, the initial-state values at the midside nodes are evaluated by averaging the coefficients of the function applied at the corner nodes. A single element must have the same function type at all nodes in the element.

Function-based initial state can also be applied if needed in a user-defined coordinate system. The coordinates needed to evaluate the initial-state data are transformed to the user-defined coordinate system before the evaluation process.

Example 5.2:  Function-Based Initial State in a User-Defined Coordinate System
! Apply linearly varying porepressure in the Y direction
p0=1e3
psl=1.3
inis,set,data,func
inis,set,dtyp,ppre
! Select a subset of elements
esel,s,elem,,1,100
local,11,0,0,0,0,0,0,30
! Change coordinate system if needed
inis,set,csys,11
inis,defi,all,,,,LINY,p0,ps1

Also see Example: Function-Based Initial State.


Release 18.2 - © ANSYS, Inc. All rights reserved.