This section provides typical cases for applying an initial state, as follows:
Although initial stress is element-based, the structure of the INISTATE command is element-type-independent.
For continuum or link elements, apply initial stress according to the specific element integration point.
For layered elements, apply initial stress based on the layer number, the layer integration point or the element integration point. Beams allow you to apply initial stress based on the cell number, the section integration point, and/or the element integration point.
For reinforced elements, you can assign different values of initial stress to different reinforcings within the same element.
For coupled-field elements CPT212, CPT213, CPT215, CPT216, and CPT217, the initial stresses to be applied are Biot’s effective stress. They are automatically written out when the output stress option is specified (INISTATE, WRITE, , , , , ,S).
The following example input shows how initial stress can be applied in such cases:
Constant Initial Stress on the Whole Model inistate,defi,,,,,100,200,300,400,500,600 Apply Constant Stress of SX=100 On Beam Element 1 inistate,defi,1,,,,100 Apply a Stress of SX=33.333 at Elem Integration Pt 3 within Element 2 inistate,defi,2,3,,,33.3333 Apply Constant Stress Of SX=200 in Cell 2 For All Selected Beam Elements inistate,defi,,,2,,200 Apply Constant Stress Of SX=200 For All Beams In A Model And Wherever There Is Material=3 inistate,set,mat,3 inistate,defi,,,,,200 Apply a Stress of SX=100,SY=200,SXY=150 for Layers 1,3,5 and SX=200,SY=0 for Layers 2,4,6 in a Layered Shell Element. Layer 1,3,5 have material 1 and Layer 2,4,6 have material 2. inistate,defi,,,1,,100,200,150 inistate,defi,,,2,,200 inistate,defi,,,3,,100,200,150 inistate,defi,,,4,,200 inistate,defi,,,5,,100,200,150 inistate,defi,,,6,,200 OR inistate,set,mat,1 inistate,defi,,,,,100,200,150 inistate,set,mat,2 inistate,defi,,,,,200 Apply a Stress of SX=33.333 at Reinf 1 for all elements inistate,defi,,,1,,33.3333
Also see Example: Initial Stress (IST File) and Example: Initial Stress (INISTATE Command).
The initial stress application example can be extended for initial strain by simply changing the data type to EPEL, as shown:
! Constant Initial Strain on the Whole Model inistate,set,dtyp,epel inistate,defi,,,,,0.1,-0.01,-0.01 !Apply a Constant Strain of EPEL X=0.01 On Beam Element 1 inistate,set,dtyp,epel inistate,defi,1,,,,0.01 !Apply a Strain of EPEL X=0.01 at Elem Integration Pt 3 within Element 2 inistate,set,dtyp,epel inistate,defi,2,3,,,0.01 !Apply a Constant Strain Of EPEL X = 1E-6 in Cell 2 For All Selected Beam Elements inistate,set,dtyp,epel inistate,defi,,,2,,1E-6 !Apply a Constant Strain Of EPEL X=1E-3 For All Beams In A Model !And Wherever There Is Material=3 inistate,set,dtyp,epel inistate,set,mat,3 inistate,defi,,,,,1E-3 ! Apply EPS X = 0.1, EPS Y = -0.02, EPS Z = -0.02, for Layers 1,3,5 and ! EPS X = 0.2, for Layers 2,4,6 ! Layer 1,3,5 have material 1 and Layer 2,4,6 have material 2. inistate,set,mat,1 inistate,defi,,,,,0.1,-0.02,-0.02 inistate,set,mat,2 inistate,defi,,,,,0.2
Also see Example: Initial Strain.
The initial stress application example can be extended for initial plastic strain by simply changing the data type to EPPL, as shown:
! Constant Initial Plastic Strain and Stress on the Whole Model inistate,set,dtyp,eppl inistate,defi,,,,,0.1 inistate,set,dtype,s inistate,defi,,,,,1000 ! Apply a Strain of EPEL X=0.01 at Elem Integration Pt 3 within Element 2. ! Here it is assumed that the initial stress is zero. inistate,set,dtyp,eppl inistate,defi,2,3,,,0.01 ! Apply accumulated equivalent plastic strain. inistate,set,dtyp,pleq inistate,defi,2,3,,,0.02 ! Apply EPS X = 0.1, EPS Y = -0.02, EPS Z = -0.02, for Layers 1,3,5 and ! EPS X = 0.2, for Layers 2,4,6 ! Layer 1,3,5 have material 1 and Layer 2,4,6 have material 2. inistate,set,dtype,eppl inistate,set,mat,1 inistate,defi,,,,,2.0 inistate,set,mat,2 inistate,defi,,,,,0.2
Also see Example: Initial Plastic Strain.
The initial stress application example can be extended for initial creep strain by simply changing the data type to EPCR, as shown:
! Apply creep strain, plastic strain, accumulated equivalent plastic strain, stress on ! all the selected elements inistate,set,dtyp,epcr inistate,defi,,,,,0.005 inistate,set,dtyp,eppl inistate,defi,,,,,0.1 inistate,set,dtyp,epeq inistate,defi,,,,,0.02 inistate,set,dtype,s inistate,defi,,,,,1000
Also see Example: Initial Creep Strain.
To use the initial-state capability with state variables via the INISTATE command, simply change the data type to SVAR, as shown:
! Apply initial state – state variables. ! This fictitious svar example contains 7 components: ! The 1st component is accumulated equivalent plastic strain. ! Components 2-7 are plastic strains values. ! at all the selected elements inistate,set,dtyp,svar inistate,defi,,,,,0.005,0.1,-0.02,0.02,0,0,0
The INISTATE command does not consider the coordinate systems of quantities stored within the state variables. It is therefore your responsibility to account for the transformations.
Also see Example: Initial Plastic Strain with State Variables .
As shown below, a node-based initial state can be applied to all nodes or to a selected subset of nodes. Layer numbers can also be specified.
! Enable Node-Based Initial State inis,set,node,1 ! Apply elastic strains at all nodes in layer 1 and 3 inistate,set,dtyp,epel inistate,defi,all,,1,,0.005 inistate,defi,all,,3,,0.005 ! Apply a different elastic strain at all nodes in layer 2 inistate,defi,all,,2,,0.010 ! Apply zero elastic strain at node 10 inistate,defi,10,,all,,0.000 ! Apply zero elastic strain at node selection nsel,s,loc,x,0 inistate,defi,all,,all,,0.000
Also see Example: Node-Based Initial Strain.
Initial pore pressure and void ratio are available for
coupled pore-pressure-thermal elements
(CPTnnn). Apply initial pore pressurel and void ratio
on CPTnnn elements by changing the data type to PPRE and
VOID, respectively.
! Apply to all the selected elements porepr=69 inistate,set,dtyp,ppre inistate,defi,,,,,porepr ! Apply to all the selected elements vratio=0.4 inistate,set,dtyp,void inistate,defi,,,,,vratio
Initial degree of saturation and relative permeability are available for coupled pore-pressure-thermal elements
(CPTnnn). Apply initial degree of saturation and
relative permeability on CPTnnn elements by changing the
data type to DSAT and RPER, respectively.
! Apply to all the selected elements init_sw=0.9 inistate,set,dtyp,dsat inistate,defi,all,,,,init_sw init_kr=0.87 inistate,set,dtyp,rper inistate,defi,all,,,,init_kr
Also see Example: Initial Degree of Saturation and Relative Permeability.
Function-based initial state is a method for applying data as a function of internal variables. Three options are available: a linear function in X coordinates (LINX), a linear function in Y coordinates (LINX), or a linear function in Z coordinates. The method is available for both node-based and element integration-point-based initial state.
The coordinates used to evaluate the value at a given location are based on initial coordinates in the load step. For user-defined field variables, the coordinates are the initial ones queried via the NLIST (or *GET) command. For a rezoning or linear perturbation model (or after issuing an UPGEOM command after a load step) where the coordinates change, the coordinates used in the subsequent load step are the updated coordinates (which become the initial coordinates for the current load step). As before, the coordinates used can be queried if necessary (NLIST or *GET). For other non-user-defined field variables (such as initial stress or strain), function-based initial state is evaluated only at the first substep in the first load step, and only the initial coordinates are used.
For higher-order elements, the initial-state values at the midside nodes are evaluated by averaging the coefficients of the function applied at the corner nodes. A single element must have the same function type at all nodes in the element.
Function-based initial state can also be applied if needed in a user-defined coordinate system. The coordinates needed to evaluate the initial-state data are transformed to the user-defined coordinate system before the evaluation process.
! Apply linearly varying porepressure in the Y direction p0=1e3 psl=1.3 inis,set,data,func inis,set,dtyp,ppre ! Select a subset of elements esel,s,elem,,1,100 local,11,0,0,0,0,0,0,30 ! Change coordinate system if needed inis,set,csys,11 inis,defi,all,,,,LINY,p0,ps1
Also see Example: Function-Based Initial State.