Several nonlinear adaptivity criteria can be defined to control the mesh during nonlinear solutions:
Also see Specifying Criteria-Checking Frequency.
This criterion is defined for current-technology structural 2-D and 3-D solid
elements, and is based on the magnitude of strain energy applied to the element
compared to the mean strain energy of components to which the element belongs.
During the substep at which mesh nonlinear adaptivity criteria are checked, if the
element’s strain energy is greater than or equal to the mean strain energy of
its components times the user-defined VAL1 (set via the
NLADAPTIVE,,ADD command), then the element is split and
remeshed.
This criterion is used to refine the mesh to achieve high-accuracy simulation in
regions where a high concentration of stress exists and elements are too large. It
can also be used to refine the mesh at certain intervals of substeps if a very small
value or 0 is input for VAL1.
This criterion is defined for current-technology structural 2-D and 3-D solid elements. A region is defined in the global Cartesian coordinates. During the substep at which mesh nonlinear adaptivity criteria are checked, if all nodes of an element are within the defined region, the element is split and remeshed.
The criterion is used to refine the mesh in regions where it is difficult to predict which elements of the model will be present, or move in to. It is commonly used in rubber seal analysis where small cavities are filled by the deformation of a compressed seal.
If some elements could potentially move into two different regions, define two different components for the same elements so that one component can be associated with each region.
Two types of contact-based criteria are available for nonlinear adaptivity:
This criterion is defined for target elements only (as the component that bears the criterion consists of target elements), but defines how solid elements underneath corresponding contact elements should be split and remeshed. This criterion is defined by the number of contact elements which should be in contact with each target element of a component. During the substep at which mesh nonlinear criteria are checked, if the number of contact elements in contact with the target element is less than the defined value, the solid element underneath the contact element is split and remeshed. Because the solid elements are split, contact elements on the faces of the solid elements are regenerated as well.
This criterion is used to allow a contact region to follow the geometry of targets more accurately. If a target has a large number of small fillets or round angles, or if it forms small cavities, splitting and mesh refinement could make convergence more difficult. The desired number of elements may not be reached when the solution is complete if the checking frequency is set too low. If the program detects that a contact element is detaching from a target surface, the underlying solid elements will no longer be split and refined, even if the desired number of elements has not been reached. Target elements with this criterion applied are taken as reference elements and therefore cannot be split or refined. Exercise caution when applying contact-based criteria on flexible-flexible boundaries and self-contact boundaries.
Should a particular target element have multiple contact-based criteria defined through different components, the program uses the most strict criterion. For example, if the desired number of elements is defined as 5 in component A and 7 in component B, the program uses 7 as the criterion for a target element present in both components.
This criterion is defined for contact elements having surface wear, specified
via the TB,WEAR command. With this option, you define the
critical ratio of magnitude of wear at the contact element to the average depth
of the solid element underlying the contact element (input as
VAL1 on NLADAPTIVE). When the
amount of wear at a contact element exceeds this critical value, the nonlinear
adaptivity criterion is met and the mesh is morphed to improve the quality of
the mesh.
During the mesh morphing process, the wear accumulated thus far is first applied and the nodal coordinates are updated to reflect the material loss due to wear. Next, the mesh is morphed to improve the quality. At the start of the subsequent analysis, the wear is initialized to zero and starts accumulating anew.
Should a particular contact element have multiple contact wear-based criteria defined through different components, the program uses the strictest criterion. For example, if the critical ratio of wear to underlying solid element depth is defined as 0.25 in component A and 0.5 in components B, the program uses 0.25 as the criterion for a contact element present in both components.
The wear criterion for mesh nonlinear adaptivity cannot be combined with any other mesh nonlinear adaptivity criterion.
For more information about using the wear-based criterion, see Improving Mesh Quality During Wear in the Contact Technology Guide.
The element components chosen to define a mesh-quality-based criterion should include only the elements falling into the large-deformation region; otherwise, the criterion may cause a larger region than necessary to be remeshed. Because the boundaries of the components cannot be remeshed, it is good practice to make the boundaries as smooth as possible, like the boundaries of the model, materials, element types, etc.
The mesh-quality-based criterion (NLADAPTIVE,,,MESH) has two options:
This criterion applies to structural 2-D plane element
PLANE182. Mesh quality is defined by element shape
(NLADAPTIVE,,,MESH,SHAPE,Value).
It works for all stress states options: plane stress, plane strain,
axisymmetric, and generalized plane strain. The mesh quality value is defined by
the element's maximum corner angle: when the angle equals or exceeds the
specified threshold (set via NLADAPTIVE), the element is
identified as a seed element to be remeshed.
The recommended maximum corner angle is 150 to 175, although any positive value between 90 and 180 is valid. A larger value results in fewer remeshings but enables remeshing from a more distorted original mesh. A maximum corner angle that is too large can introduce mapping errors, leading to residual forces that cannot be balanced in later substeps. A value that is too small causes unnecessary meshing, or a new mesh that is not much better than the original mesh.
This criterion applies to structural 3-D solid element
SOLID285, a linear tetrahedral element. Mesh
quality is defined by element skewness
(NLADAPTIVE,,,MESH,SKEWNESS,Value)
as:
where is the volume of the element under calculation and
is the volume of the standard tetrahedral linear element
inscribed in the same sphere as the element under calculation.
When the element under calculation has an ideal shape (that of a standard
tetrahedral element), and skewness = 0. When the element under calculation has the
least ideal shape (that of a flat element),
and skewness =1. For the linear tetrahedral element,
therefore, skewness is always between 0 and 1, with 1 being a flat
element.
The skewness value serves as the threshold value for detecting an element to remesh. When an element’s skewness is >= the specified threshold, that element is identified as a seed element to be remeshed.
The recommended skewness value is approximately 0.9 to 0.95. An excessively small skewness value may lead to many unnecessary remeshings, and an excessively large value may cause remeshing to occur too late for the subsequent substep to converge.