3.11. Mesh Nonlinear Adaptivity Examples

The following example input files show demonstrate to apply mesh nonlinear adaptivity:

3.11.1. Example Input: Rubber Seal Simulation

Following is the input for the problem discussed in Example: Rubber Seal Simulation:

/batch,list

/prep7

/com geometry parameters
rf = 1
yd = 6
yf = 12
xc = 0
yc = 12
disp = -4.0
w = 3

/com element types and size
el = w
et,1,182
keyopt,1,3,2
!keyopt,1,6,1

et,2,169
et,3,171
keyopt,3,9,0
keyopt,3,10,1
!keyopt,3,2,3

/com materials
c10=62.3584129
c01=-37.8485452
dd=1.E-03

tb,hyper,1,,2,mooney
tbdata,1,c10,c01,dd

mp,mu,2,0.0

r,2

/com create the model
k,1,xc,yc
k,2,xc+3*w,yc
k,3,w,0.0
k,4,w,yd
k,5,3*w,yd
rect,0,w,0,yd
rect,0,w,yd,yf
/pnum,line,1
l,1,2
l,3,4
l,4,5
lfillt,10,11,rf

/com create mesh
esize,el
mat,1
type,1
real,1
amesh,1,2
/pnum,elem,1
/pnum,node,1
nummrg,node
numcmp,node
/replot

/com the 1st contact pairs
mat,2
real,2
type,2

esize,yf
lmesh,9
allsel,all

type,3  
lsel,,,,6,7 
nsll,,1 
esln,,0 
esurf   
alls

/com the 2nd contact pairs
real,3
type,2

lplot
esize,yf
lmesh,9,12
lsel,s,line, ,10,12
esll,s,1
esurf, ,reverse
allsel,all

lplot
type,3  
lsel,,,,6
lsel,a,,,2
nsll,,1 
esln,,0 
esurf   
alls

/com boundary condition

/com rigid punch
lsel,,,,9
nsll,,1
d,all,uy,disp
d,all,ux,0.0
alls

/com rigid die face
lsel,,,,10,12
nsll,,1
d,all,uy,0.0
d,all,ux,0.0
alls

/com left side
nsel,,loc,x,0
d,all,ux,0.0
alls

/com bottom
nsel,,loc,y,0
d,all,uy,0.0
alls

/com check the contact definition
cncheck
elist
finish

/solution

/com define nonlinear adaptive criterion
esel,,ename,,182
cm,solid,elem
allsel
nlad,solid,add,box,xyzr,-0.0,9,5,12
nlad,solid,on,,,-2

pred,off
rescontrol,,all,1,20
eresx,no
nlgeom,on
time,1
NSUBST,50,500,5
outres,all,all
solv
finish

3.11.2. Example Input: Crack Simulation

Following is the input for the problem discussed in Example: Crack Simulation:

/batch,list
/prep7
! MATERIAL PROPERTIES 
et,1,183
keyopt,1,1,0
keyopt,1,6,1
MP,PRXY,1,0.3 
MPTEMP,1,0,500            ! Define temperatures for Young's modulus
MP,EX,1,12E6,-8E3         ! C0 and C1 terms for Young's modulus
TB,BKIN,1,2               ! Activate a data table
TBTEMP,0.0                ! Temperature = 0.0
TBDATA,1,44E3,1.2E6       ! Yield = 44,000; Tangent modulus = 1.2E6
TBTEMP,500                ! Temperature = 500
TBDATA,1,29.33E3,0.8E6    ! Yield = 29,330; Tangent modulus = 0.8E6
TBLIST,BKIN,1             ! List the data table
/XRANGE,0,0.01            ! X-axis of TBPLOT to extend from varepsilon=0 to 0.01
TBPLOT,BKIN,1             ! Display the data table

! GEOMETRY 
blc4,0,0,10,0.5        
blc4,0,0,10,-0.5
lsel,s,loc,y,0
lsel,a,loc,y,0.5
lsel,a,loc,y,-0.5
lesize,all,,,20
lsel,inve
lesize,all,,,5

amesh,all
elist
allsel,all

nsel,s,loc,y,0
nsel,r,loc,x,0,7
nummrg,node
allsel,all
! COMPONENT
esel,all
cm,cm1,elem
allsel,all

esel,all
cm,cm2,elem
allsel,all

! LOADS
nsel,s,loc,x,0
d,all,all
allsel,all

nsel,s,loc,y,0.5
nsel,r,loc,x,10
f,all,fy,5500
allsel,all

nsel,s,loc,y,-0.5
nsel,r,loc,x,10
f,all,fy,-5500
allsel,all

nplot
finish
/solu
nlgeom,on                       ! large displacement analysis ON
outres,all,all                  ! all solutions are written
rescontrol,define,all,all       ! write every substeps in a file
eresx,no                        ! no interpolation for the point of integration
time,1
nsubst,50,100,20
/nerr,,,,1                      ! prevent the GUI for closing if no convergence

! NON LINEAR ADAPTIVITY 

nlad,cm2,add,energy,mean,1
nlad,cm2,on,,,-3
allsel,all
solve 
finish

! POSTPROCESSING 
/post1
/out

set,last
nsel,s,loc,y,0
nsel,r,loc,x,0,7
esln,s,0,all
presol,s,eqv

finish
/exit

3.11.3. Example Input: 3-D Metal Forging Simulation

Following is the input for the problem discussed in Example: 3-D Metal Forging Simulation.

/batch,list
/config,nproc,1
/PREP7
!-----------geometry parameters---------------	!mm
cylinder_radius		=	500	
cylinder_offset		=	1000	
block_height		=	1000	
radius_fillet		= 	33
!---------initial meshing parameters------------
block_esize			=	200			
cylinder_esize		=	200			
!------------loading parameters----------------
cylinder_disp		=	-800		
!------------NLAD parameters------------------
skw_			=	0.9							!skewness threshold
freq			=	1							!NLAD frequency (1 means check every substep)
start_time		=	0							!beginning time for NLAD interval
end_time		=	0.95						!end time for NLAD interval
!------------remeshing parameters---------------
sculpt_layers	=	4							!no. of sculpting layers
!******************material properties*****************
MP,EX,1,70e3									!aluminium material properties															
MP,NUXY,1,0.33									!poisson's ratio
MP,MU,1,0										!coefficient of friction															
TB,BISO,1,1										!bilinear isotropic material
TBDATA,1,20										!yield stress in MPa
TBDATA,2,7e3									!tangent modulus in MPa

!------------geometry creation-------------------
blc4,0,0,block_height,block_height,block_height
k,9,0,cylinder_offset,0
k,10,0,cylinder_offset,cylinder_radius
k,11,0,cylinder_offset+cylinder_offset,cylinder_radius
k,12,0,cylinder_offset+cylinder_offset,0
l,9,10 
l,10,11
l,11,12
l,12,9                       
lfil,13,14,radius_fillet
al,13,17,14,15,16
vrotat,7,,,,,,9,12,90

!---------element types & settings-----------
et,1,285 
et,2,170
et,3,173
keyo,3,10,2										!update contact stiffness every iteration
!-------------general meshing----------------
type,1
mat,1          
real,1           
esize,block_esize
vmesh,1
!-------------contact pair 1----------------
real,2                     
!---------------target elements--------------
type,2
mat,2                      	
asel,s,area,,8,10
aesize,all,cylinder_esize
amesh,all
alls
!---------------contact elements-----------
type,3
mat,1                  
asel,s,area,,4
nsla,s,1
esln
esurf
alls
!--------------create components-----------
esel,s,ename,,285
cm,comp1,elem									!create NLAD component
alls
!-----boundary conditions & loading-------	
asel,s,area,,5,6
nsla,s,1
d,all,ux,0.0
alls
asel,s,area,,1,2
nsla,s,1
d,all,uz,0.0
alls
asel,s,area,,3	
nsla,s,1
d,all,uy,0.0
alls
asel,s,area,,7,12
nsla,s,1
d,all,uz,0.0
d,all,ux,0.0
d,all,uy,cylinder_disp
alls
fini

/SOLU         															
!--------------general solution settings--------
nlgeom,on
eresx,no
outres,all,all
!---------------NLAD settings-------------------!check NLAD parameters section above for values
nlad,comp1,add,mesh,skew,skw_       			!nlad with mesh-quality-based criterion
nlad,comp1,on,,,freq,start_time,end_time        
!------------remeshing settings---------------	!check remeshing parameters section above for values
nlmesh,nlay,sculpt_layers
!---------------step settings-------------------
time,1  
nsubst,100,10000,10

alls
solve
fini

!---------------POSTPROCESSING-------------------------
/POST1
set,list
fini
/exit

3.11.4. Example Input: 2-D Metal Extrusion Simulation

Following is the input for the problem discussed in Example: 2-D Metal Extrusion Simulation.

/batch,list
/config,nproc,1

/PREP7
h1=19.5
b1=45
h2=6.5
b2=22.5
b3=5
h3=17
el=h1/8

et,1,182
keyopt,1,3,5
keyopt,1,6,1

mp,ex,1,1.0e+6
mp,nuxy,1,0.3
tb,biso,1,
tbmodif,2,1,8.0e2
tbmodif,3,1,1.0e4

/com --- Rigid target
k,1,0,h1
k,2,b1,h1
k,3,b1+b2,h2
k,4,b1+b2+b3,h2
k,5,b1+b2+b3,h3

l,1,2
l,2,3
l,3,4
l,4,5
LFILLT,1,2,5, , 
LFILLT,2,3,5, , 
/pnum,line,1

/com --- Rectangular block
k,10,0,0
k,11,b1,0
k,12,b1,h1
k,13,0,h1
l,10,11
l,11,12
l,12,13
l,13,10
lfillt,8,9,el
al,7,8,11,9,10
esize,el
real, 1
mat, 1
type, 1
amesh, 1

/com --- Element type definitions for contact pair
mp,mu,2,0.0
r,2
et,2,169
et,3,171
keyopt,3,9,0
keyopt,3,10,2

/com --- Mesh target surface
mat, 2
real, 2
type, 2
lmesh,1,6

/com --- Create contact elements
type,3
real, 2
lsel, s, line, , 8,9
lsel, a, line, , 11
nsll,,1
esln,,0
esurf
alls

/com --- Apply Constraints

nsel,s,loc,y
d,all,uy,0.0
alls

lsel,s,line,,1,6
nsll,,1
d,all,all,0.0
alls

nsel,s,loc,x
d,all,ux,30
alls

esel,s,ename,,182
cm,c1,elem						!create NLAD component
alls
fini

/SOLU
nlgeom,on
eresx,no
pred,off
outres,all,all

time,1
NSUBST,20,1000,5
alls

gsgdata,2,0,0,0,0
gsbdata,lfiber,0,rotx,0,roty,0
gslist,geometry
gslist,bc
alls

!-----Nonlinear Adaptive Region
cmsel,all
nlad,c1,add,mesh,shape,155		!nlad with mesh-quality-based criterion
nlad,c1,on,,,1

nlmesh,nlay,100					!no. of sculpting layers
nlmesh,grad,0					  !option for mesh gradient control
nlmesh,srat,0.9					!control global sizing of new mesh

nlad,all,list,all				
nlmesh,list						

alls
SOLVE
fini

/POST1
set,list
fini
/exit

3.11.5. Example Input: Compression of 2-D Thermo-hyperelastic U-Shape Simulation

/batch,list
/title, 2D thermo-hyperelastic U shape 

/prep7
/nopr

h=0.5
b = 4
x0 = 0.0
y0 = 0.0
x1 = 5.0
y1 = x0+h
y2 = x0+h+b

et,1,222,11
keyo,1,3,2
keyo,1,11,1

tb,hype,1,1,3,ogde
tbdata,1,3.2084e-009,7.281,0.035198,3.0149,6.3712,2.0493

mptemp,1,100,200,300,400,500
mpdata,alpx,1,1,2.568e-6,3.212e-6,3.594e-6,3.831e-6,3.987e-6
mpdata,kxx,1,1,14.64,9.83,7.32,5.75,4.92

! upper contact pair
et,2,169
r,2

et,3,171
keyo,3,1,1        ! ux/uy/temp
keyo,3,9,0
keyo,3,10,0

mp,mu,2,0.0

! lower contact pair
et,4,169
r,3

et,5,171
keyo,5,1,1        ! ux/uy/temp
keyopt,5,9,0
keyopt,5,10,0

mp,mu,3,0.0

! self-contact pair
et,6,169
r,4
rmodif,4,14,10.0
et,7,171
keyo,7,1,1        ! ux/uy/temp
keyopt,7,9,0
keyopt,7,10,0

mp,mu,4,0.0

et,8,169
r,5
rmodif,5,14,10.0
et,9,171
keyo,9,1,1        ! ux/uy/temp
keyopt,9,9,0
keyopt,9,10,0

mp,mu,5,0.0

! Geometry

! keypoints
k, 1, x0, y0
k, 2, x1, y0
k, 3, x0, y0+h
k, 4, x1, y0+h

k, 5, x0, y2
k, 6, x1, y2
k, 7, x0, y2+h
k, 8, x1, y2+h

k, 9, x1, y0+h+b/2 
k, 10, x1, y0+h+b/2, y0+h+b/2
circle, 9, , 10, 4, 180
circle, 9, , 10, 2, 180 

! line definitions
l, 1, 14
l, 3, 11
l,1, 3
l, 13, 5
l, 16, 7

l, 5, 7

l,11,14
l,13,16

l,12,15

! area definitions
al,5,11,6,7
al,3,13,1,11
al,4,12,2,13
al,8,12,9,10

esize,0.15
real,1
mat,1
type,1
amesh,all

asel,s,area,,2,3
esla,s
esel,r,type,,1
cm,cm222,elem
alls

! contact definitions
k, 17, x0-2.0, y0
k, 18, x1+5.0, y0

k, 19, x0-2.0, y0+h+h+b
k, 20, x1+5.0, y0+h+h+b

l, 18, 17
l, 19, 20

! 1st contact pair -- top surface pair
mat,2
real,2
type,2

! mesh target surface
lmesh,15

! define pilot node
*get,PilotKpt,kp,,num,max
PilotKpt=PilotKpt+1
k,PilotKpt,x0+x1/2,y0+h+h+b+2.0
*get,PilotID,node,,num,max
PilotID=PilotID+1
nkpt,PilotID,PilotKpt
tshap,pilo
e,PilotID

! define contact elements
type,3
real,2
lsel,s,line,,4
lsel,a,line,,9
nsll,,1
esln,,0
esurf
alls

! second contact pair --- bottom pair
mat,3
type,4
real,3

! mesh target surface
lmesh,14

! mesh contact elements
type,5
real,3

lsel,s,line,,5
lsel,a,line,,3
nsll,,1
esln,,0
esurf
alls

! 1st self-contact pair
mat,4
type,6
real,4
lsel,s,line,,6,8,2
nsll,,1
esln,,0
esurf
alls

type,7
real,4
lsel,s,line,,6,8,2
nsll,,1
esln,,0
esurf
alls

! 2nd self-contact pair
mat,5
type,8
real,5
lsel,s,line,,1,2
nsll,,1
esln,,0
esurf
alls

type,9
real,5
lsel,s,line,,1,2
nsll,,1
esln,,0
esurf
alls

! Initial boundary conditions
d,PilotID,ux,0.0
d,PilotID,uy,-4.1
d,PilotID,rotz,0.0

nsel,s,loc,x,0.
d,all,ux,0.
alls

tref,20.0

DL,14,,temp,100
DL,15,,temp,500
alls

cnch,auto
rmodif,4,14,1000.0
rmodif,5,14,1000.0
fini

/solu
/nopr
nlad,cm222,add,mesh,shape,150
nlad,cm222,on,,,1

nlmesh,nlay,10
nlmesh,srat,0.8
nlmesh,bdra,10
nlmesh,grad,2

nlgeom,on
eresx,no
time,1
nsub,20,100,5
rescontrol,define,all,all
outres,all,all
solve
fini

/post1
set,list
finish
/exit,nosave

Release 18.2 - © ANSYS, Inc. All rights reserved.