This example illustrates a transient induction heating problem. The problem demonstrates the use of a solution sequence alternating between an electromagnetic harmonic analysis and a transient heat transfer analysis with restarting.
A very long steel billet undergoes surface heat treating by rapidly raising the temperature of the billet surface by means of an induction coil. The coil is placed in close proximity to the billet surface and is excited by a large alternating current at high frequency. The AC current induces heat in the billet, most notably at the surface, which quickly raises the surface temperature.
A simplified geometry considers only a finite length strip of the long billet, essentially reducing the problem to a one-dimensional study as shown in Figure 5.8: Axisymmetric 1-D Slice of the Induction Heating Domain.
The billet will heat up to over 700°C. This temperature dependency of the material properties must be considered for both the thermal problem and the electromagnetic problem. You must solve the problem sequentially, first doing an AC harmonic electromagnetic analysis and then a transient thermal analysis. In addition, you must repeat the electromagnetic analysis at various time intervals to correct for temperature dependent properties which will affect the solution and hence the heating load to the billet. Figure 5.9: Solution Flow Diagram shows the solution flow diagram.
The procedure for the induction heating problem is as follows.
Develop an attribute relationship for the modeled regions as shown in Table 5.3: Physics Environment Attributes.
Build the model of the entire domain. Assign the attributes to the different regions. (The billet surface will be used to define a surface effect element for thermal radiation. It will be handled differently than the solid regions.)
Create the electromagnetic physics environment by defining element types and material properties as shown below.
Assign appropriate nominal boundary conditions and loads as shown below.
Assign appropriate load step and solution options.
Write the electromagnetic physics environment to a file.
Create the thermal physics environment as follows:
Delete nominal boundary conditions and reset options.
Change the element types from electromagnetic to thermal as well as KEYOPT options. Specify the null element type in the air and coil region (assume the heat transfer analysis only considers the billet).
Define the thermal properties and real constants.
Assign appropriate nominal boundary conditions and loads as shown below.
Assign appropriate load step options and solution options
Write the thermal physics environment to a file.
Prepare a *DO loop that will cycle between a harmonic electromagnetic analysis and a transient thermal analysis.
Read in the electromagnetic physics environment and solve the harmonic analysis.
Read in the temperatures and body force loads for material property evaluation.
Use /ASSIGN to redirect the file assignment for the ESAV and EMAT files for future use in a thermal transient restart.
Read in the thermal physics environment.
Read in the Joule heat generation rate from the electromagnetic analysis.
Solve the thermal transient for a preset Δ time increment.
Reassign file to their defaults.
The command text below demonstrates the problem input. All text prefaced with an explanation point (!) is a comment.
/batch /filnam,induc /prep7 shpp,off /title, induction heating of a solid cylinder billet /com, et,1,13,,,1 ! PLANE13, axisymmetric, AZ dof et,2,13,,,1 et,3,151,,,1,1,1 ! SURF151, thermal, radiation r,3,0 ! Real constant set for SURF151 row=.015 ! outer radius of workpiece ric=.0175 ! inner radius of coil roc=.0200 ! outer radius of coil ro=.05 ! outer radius of model t=.001 ! model thickness freq=150000 ! frequency (Hz.) pi=4*atan(1) ! pi cond=.392e7 ! maximum conductivity muzero=4e-7*pi ! free-space permeability mur=200 ! maximum relative permeability skind=sqrt(1/(pi*freq*cond*muzero*mur)) ! skin depth ftime=3 ! final time tinc=.05 ! time increment for harmonic analysis time=0 ! initialize time delt=.01 ! maximum delta time step emunit,mks ! set magnetic units mp,murx,1,1 ! air relative permeability mp,murx,3,1 ! coil relative permeability mptemp,1,25.5,160,291.5,477.6,635,698 ! temps for relative permeability mptemp,7,709,720.3,742,761,1000 mpdata,murx,2,1,200,190,182,161,135,104 ! steel relative permeability mpdata,murx,2,7,84,35,17,1,1 mptemp mptemp,1,0,125,250,375,500,625 ! temps for resistivity mptemp,7,750,875,1000 mpdata,rsvx,2,1,.184e-6,.272e-6,.384e-6,.512e-6,.656e-6,.824e-6 mpdata,rsvx,2,7,1.032e-6,1.152e-6,1.2e-6 ! steel resistivity rectng,0,row,0,t ! billet rectng,row,ric,0,t ! air-gap rectng,ric,roc,0,t ! coil rectng,roc,ro,0,t ! outer air aglue,all numcmp,area ksel,s,loc,x,row ! select keypoints at outer radius of workpiece kesize,all,skind/2 ! set meshing size to 1/2 skin depth ksel,s,loc,x,0 ! select keypoints at center kesize,all,40*skind ! set meshing size lsel,s,loc,y,t/2 ! select vertical lines lesize,all,,,1 ! set 1 division through thickness lsel,all asel,s,area,,1 aatt,2,1,1 ! set attributes for billet region asel,s,area,,3 aatt,3,1,2 ! set attributes for coil region asel,s,area,,2,4,2 aatt,1,1,2 ! set attributes for air region asel,all mshape,0,2d mshk,1 amesh,1 ! mesh billet area lsel,s,loc,y,0 lsel,a,loc,y,t lsel,u,loc,x,row/2 lesize,all,.001 lsel,all amesh,all ! mesh remaining areas n ! create space node for SURF151 *get,nmax,node,,num,max lsel,s,loc,x,row type,3 real,3 mat,2 lmesh,all ! mesh billet outer radius with SURF151 *get,emax,elem,,num,max emodif,emax,3,nmax ! modify element to add space node for radiation et,3,0 ! reset type 3 to null element nsel,s,loc,x d,all,az,0 ! apply flux-normal b.c. nsel,all esel,s,mat,,3 bfe,all,js,,,,15e6 ! apply current density to coil esel,all finish /solu antyp,harm harfrq,150000 physics,write,emag ! write emag physics file finish /prep7 lsclear,all ! clear all b.c.'s and options et,1,55,,,1 ! PLANE55 thermal element, axisymmetric et,2,0 ! null element type for coil and air region et,3,151,,,1,1,1 ! SURF151 element for radiation keyopt,3,9,1 r,3,1,5.67e-8 ! form factor, Stefan-Boltzmann constant mptemp mptemp,1,0,730,930,1000 ! temps for conductivity mpdata,kxx,2,1,60.64,29.5,28,28 mptemp ! temps for enthalpy mptemp,1,0,27,127,327,527,727 mptemp,7,765,765.001,927 mpdata,enth,2,1,0,91609056,453285756,1.2748e9,2.2519e9,3.3396e9 mpdata,enth,2,7,3.548547e9,3.548556e9,4.3520e9 mp,emis,2,.68 ! emissivity finish /solu antype,trans toffst,273 tunif,100 ! initial uniform temperature d,nmax,temp,25 ! ambient temperature cnvtol,heat,1 ! convergence tolerance kbc,1 ! step loads trnopt,full autos,on ! auto time-stepping deltim,1e-5,1e-6,delt,on ! time step control outres,basic,all ! save all load step information physics,write,thermal ! write thermal physics file finish *do,i,1,ftime/tinc ! solution *do loop time=time+tinc ! increment time physics,read,emag ! read emag physics file /solu *if,i,eq,1,then tunif,100 ! initial temperature *else ldread,temp,last,,,,,rth ! read thermal analysis temperatures *endif solve ! solve harmonic analysis finish physics,read,thermal ! read thermal physics file /assign,esav,therm,esav ! redirect files for use in thermal restart /assign,emat,therm,emat /solu parsav,scalar,parameter,sav !save parameters before multiframe restart *if,i,gt,1,then antype,trans,rest ! thermal restart *endif parres,new,parameter,sav !restore parameters after multiframe restart time,time ! time at end of thermal run esel,s,mat,,2 ! select billet region ldread,hgen,,,,2,,rmg ! apply coupled joule heating load from emag esel,all solve finish /assign,esav ! reassign files to default /assign,emat *enddo ! end of solution looping finish save ! save database /post26 ! time-history postprocessor /show nsol,2,1,temp,,tempcl ! store temperature at billet centerline nsol,3,2,temp,,tempsurf ! store temperature at billet outer diameter plvar,2,3 ! plot temperature rise over time prvar,2,3
Figure 5.12: Temperature Response of Solid Cylinder Billet shows the temperature results obtained in this analysis.