5.3. Transferring Loads Between Physics

The LDREAD command links the different physics environments in a coupled-field analysis, enabling you to read in specified results data from the first physics environment solution analysis and applying them as loads for the next environment's solution.

The LDREAD command reads results data from the results file and applies them as loads. The following table briefly explains what happens to results data from various analysis types when LDREAD reads them in as loads on another analysis:

Table 5.1:  How Results Transferred by LDREAD Become Loads

These analysis results ...Become loads on this type of analysis ...
Temperatures from a thermal analysis [TEMP, TBOT, TE2, . . . TTOP]Body force for structural analyses or nodal loads (temperatures) for thermal analyses
Forces from a static, harmonic, or transient magnetic analysis [FORC]Force loads on a structural analysis
Forces from an electrostatic analysis [FORC]Force loads on a structural analysis
Joule heating from a magnetic analysis [HGEN]Body force element (heat generation) loads onto a thermal analysis
Source current density from a current conduction analysis [JS]Body force element (current density) loads on a magnetic field analysis
Reaction loads from any analysis [REAC]Force loads on any analysis

5.3.1. Compatible Element Types

There are several criteria for determining if element types are compatible across physics environments. Before reading further about this topic, you need to understand the following terms:

Base geometry

An element's base geometry is established by the default configuration documented in the Element Reference. For solid elements, base geometry includes quadrilateral, triangle, hexahedron (brick), and tetrahedron shapes.

Degenerate geometry

Many elements may take on a degenerate form from the base geometry. For instance, a quadrilateral element may degenerate to a triangle element, or a brick element may degenerate to a wedge, tetrahedron, or pyramid shape.

Element order

Elements are available in a lower order form (first order) or a higher order form (second order). The higher order elements have midside nodes; the lower order elements do not. In many instances, you can generate the higher order elements without midside nodes.

Across multiphysics environments, element types must maintain a consistent base geometry. If an element type allows a degenerate geometry, the corresponding element type in the other physics must also allow the same degenerate geometry.

Elements of different element order may or may not be compatible across physics environments. The nature of the coupled load read by the LDREAD command will determine compatibility. In addition, certain element types have specific KEYOPT options that support lower and higher order coupled load transfer.

The items listed below are loads which you can read from first or second order elements and apply to first or second order elements in another physics environment:

  • Body force temperatures [TEMP, TBOT, TE2, . . . TTOP]

  • Body force element heat generation [HGEN]

  • Source current density [JS]

  • Surface pressure [PRES]

  • Surface heat fluxes [HFLU]

  • Surface film coefficients and bulk temperature [HFLM]

Loads which require compatibility in element order are as follows:

  • Force loads* [FORC]

  • Reaction loads [REAC]

* The following electromagnetic elements support first or second order structural elements with a KEYOPT setting: PLANE121, SOLID122, and SOLID123.

If physics environments are established by switching between element orders, you must initially create the finite element mesh with the higher order elements. Table 5.2: Compatible Element Types Across Physics Environments partially summarizes compatible element types:

Table 5.2:  Compatible Element Types Across Physics Environments



Note:  If a mesh involves a degenerate element shape, the corresponding element type must allow the same degenerate shape. To be compatible, elements with a VOLT degree of freedom must also have the same reaction force (see Element Compatibility in the Low-Frequency Electromagnetic Analysis Guide).


  1. Supports only first order elements requiring forces.

  2. Element KEYOPT option required to support first order elements requiring forces.

5.3.2. Types of Results Files You May Use

You typically you work with several different types of results files containing different types. All results files for your analysis will have the same filename -- the jobname you specified using the /FILNAME command (Utility Menu> File> Change Jobname). However, you can distinguish among different results files by looking at their extensions:

Jobname.RMG Electromagnetic results file
Jobname.RTH Thermal results file
Jobname.RST All other types of results files (structural and multiple physics)

Release 18.2 - © ANSYS, Inc. All rights reserved.