5.6. Example Thermal-Stress Analysis Using Multiple Physics Environments

This section shows you how to solve the same thermal-stress problem covered in the previous section, this time using a single database with multiple physics environments. In this particular case, it may not be advantageous to use this approach because the problem is a simple one-way coupling. However, it will allow for quick switching between physics environments for subsequent modeling or analysis.

The basic procedure for this problem is shown below:

  1. Define the thermal problem.

  2. Write the thermal physics file.

  3. Clear boundary conditions and options.

  4. Define the structural problem.

  5. Write the structural physics file.

  6. Read the thermal physics file.

  7. Solve and postprocess the thermal problem.

  8. Read the structural physics file.

  9. Read the temperatures from the thermal results file.

  10. Solve and postprocess the physics file.

The command text shown below demonstrates the problem input. All text prefaced with an exclamation point (!) is a comment.

/batch,list
/show
/title, thermal stress in concentric cylinders - physics environment method
/prep7
et,1,plane77,,,1          ! PLANE77 axisymmetric options
mp,kxx,1,2.2              ! Steel conductivity
mp,kxx,2,10.8             ! Aluminum conductivity
rectng,.1875,.4,0,.05     ! Model
rectng,.4,.6,0,.05
aglue, all
numcmp,area
asel,s,area,,1            ! Assign attributes to solid model
aatt,1,1,1
asel,s,area,,2
aatt,2,1,1
asel,all
esize,.05
amesh,all                 ! Mesh model
nsel,s,loc,x,.1875
d,all,temp,200            ! Apply thermal loads
nsel,s,loc,x,.6
d,all,temp,70
nsel,all
physics,write,thermal     ! Write the thermal physics file
physics,clear             ! Clear all bc's and options

et,1,82,,,1               ! Switch to structural element, SOLID82
mp,ex,1,30e6              ! Define structural steel properties
mp,alpx,1,.65e-5
mp,nuxy,1,.3
mp,ex,2,10.6e6            ! Define aluminum structural properties
mp,alpx,2,1.35e-5
mp,nuxy,2,.33
nsel,s,loc,y,.05          !Apply structural boundary conditions
cp,1,uy,all
nsel,s,loc,x,.1875
cp,2,ux,all
nsel,s,loc,y,0
d,all,uy,0
nsel,all
tref,70
physics,write,struct      ! Write structural physics file
save                      ! Save database
finish
/solu
physics,read,thermal      ! Read thermal physics file

solve                     ! Solve thermal problem
save,thermal,db           ! Save thermal model for subsequent postprocessing
finish
/post1
path,radial,2             ! Define path name and number of path points
ppath,1,,.1875            ! Define path by location
ppath,2,,.6
pdef,temp,temp            ! Interpret temperature to path
pasave,radial,filea       ! Save path to an external file
plpath,temp               ! Plot temperature solution
finish

/solu
physics,read,struct       ! Read structural physics file
ldread,temp,,,,,,rth      ! Read in temperatures from thermal run
solve                     ! Solve structural problem
finish
/post1
paresu,raidal,filea       ! Restore path
pmap,,mat                 ! Set path mapping to handle material discontinuity
pdef,sx,s,x               ! Interpret radial stress
pdef,sz,s,z               ! Interpret hoop stress
plpath,sx,sz              ! Plot stresses
plpagm,sx,,node           ! Plot radial stress on path geometry
finish

Figure 5.6:  Stress Profile Across Material Discontinuity

Stress Profile Across Material Discontinuity

Figure 5.7:  Radial Stress Displayed on Geometry

Radial Stress Displayed on Geometry


Release 18.2 - © ANSYS, Inc. All rights reserved.