8.3. Use Pass

In the use pass, you run the ROM to obtain solutions of the coupled electrostatic-structural behavior of the device. The ROM is activated through the ROM144 element type. This element is a multiport element that may be used to perform multiple analysis simulation, including static, prestressed modal, prestressed harmonic or nonlinear transient analysis. The different analysis types are discussed in detail in the individual analysis guides. The use pass consists of the following steps.

Figure 8.4:  Use Pass Flowchart

Use Pass Flowchart

The following sections describe each step.

8.3.1. Clear Database

At this point you should clear the database.

Command(s): /CLEAR
GUI: Utility Menu> File> Clear & Start New

8.3.2. Define a Jobname

Be sure to define a jobname that is different than the one used for the generation pass. For example, you could specify a jobname USE. This way, you can be sure that generation pass files from the modal analysis will not be overwritten.

Command(s): /FILNAME
GUI: Utility Menu> File> Change Jobname

8.3.3. Resume ROM Database

The use pass is based on the reduced order model. Therefore, you must resume the ROM specifications. Only one ROM database may be active for a use pass.

Command(s): RMRESUME
GUI: Main Menu> ROM Tool> ROM Database> Resume

8.3.4. Define Element Type

You then define the ROM element (ROM144) as one of the element types. Set KEYOPT(1) to one if master nodes should be considered for the use pass.

Command(s): ET
GUI: Main Menu> Preprocessor> Element Type> Add/Edit/Delete

The ANSYS Circuit Builder (see Electric Circuit Analysis in Low-Frequency Electromagnetic Analysis Guide) provides a convenient tool for constructing the ROM144 element and any attached linear circuit elements (CIRCU124), mechanical spring, mass, and damper elements (COMBIN14, MASS21, and COMBIN39), or the electromechanical transducer element (TRANS126).

ROM144 fully couples the electrostatic and structural domains. It is defined by twenty (KEYOPT(1) = 0) or thirty nodes (KEYOPT(1) = 1):

  • Nodes 1 to 10 are modal ports and relate modal amplitudes (EMF degree of freedom) to modal forces. The node numbers represent the numbers of the involved modes from the ROM database. For example, if modes 1, 3, and 5 are used in the ROM database, the modal amplitudes of modes 1, 3, and 5 are mapped to nodes 1, 2, and 3 respectively. Modal displacements can be set to zero to deactivate modes.


    Note:  Only the first 9 nodes may be used for modal amplitude degrees of freedom.


  • Nodes 11 to 20 are electrical conductor ports and relate voltage (VOLT degree of freedom) to current. Node 11 represents the first conductor, node 12 represents the second conductor, and so on. Current can only be imposed in a harmonic or transient analysis.


    Note:  Only the first 5 ports can be used.


  • Nodes 21 to 30 are nodal ports relating displacements (UX degree of freedom) to forces at master nodes. Node 21 represents the first defined master node, node 22 represents the second master node, and so on. Master displacements and forces are always mapped to the UX degree of freedom and FX force label independent from their real DOF direction. Node to node contact or spring damper elements (COMBIN14, COMBIN40) can be directly attached to the UX degree of freedom at master nodes. Only elements that have a single UX degree of freedom may be used at a displacement port.

See the Element Reference for more detailed information on this element.

8.3.5. Define Nodes

You then define nodes for ROM144. If KEYOPT(1) is zero, 20 nodes must be defined. Otherwise, define 30 nodes. Use the circuit builder or one of the following:

Command(s): N
GUI: Main Menu> Preprocessor> Modeling> Create> Nodes> In Active CS

8.3.6. Activate ROM Database

The next step is to activate the ROM database for the use pass.

Command(s): RMUSE
GUI: Main Menu> Preprocessor> Loads> Analysis Type> Analysis Options

8.3.7. Define Node Connectivity

In this step, you define the node connectivity of the ROM144 element. Use the Circuit Builder or one of the following:

Command(s): E, EMORE
GUI: Main Menu> Preprocessor> Modeling> Create> Elements> Thru Nodes

You need to issue the E command once for the first eight nodes and the EMORE command two (KEYOPT(1) = 0) or three (KEYOPT(1) = 1) times to define the other nodes for the ROM144 element.

8.3.8. Define Other Model Entities

You then define other elements attached to the ROM144 element with the Circuit Builder as shown in Figure 8.5: ROM144 and Attached Elements and exit the preprocessor. If the desired 1-D element is not supported in the circuit builder, it may be defined manually (for example, COMBIN40).

Command(s): ET, FINISH
GUI: Main Menu> Preprocessor> Element Type> Add/Edit/Delete
Main Menu> Finish

Figure 8.5:  ROM144 and Attached Elements

ROM144 and Attached Elements

8.3.9. Using Gap Elements with ROM144

If you intend to operate the ROM144 element at voltage levels that exceed the "pull-in" voltage (voltage level at which the device snaps down onto the conductor), the element will not converge unless gap elements constrain the active modal amplitude degrees of freedom (EMF). The following guidelines are recommended.

  • Create COMBIN40 elements for active EMF degrees of freedom.

  • Use the UX degree of freedom option on the COMBIN40 element.

  • Create the I and J nodes of the COMBIN40 element at the same location (coincident) as the modal amplitude (EMF) degree of freedom.

  • Use an appropriate gap stiffness. 1E5 is suggested for most MEMS applications.

  • Set the gap distance equal to the lower or upper bound displacement of the mode as computed from the RMMSELECT command (whichever is greater).

  • Set the displacement of node I of the gap element to zero.

  • Use a constraint equation to enforce equivalent displacement of the J node of the gap element (UX degree of freedom) to the modal amplitude (EMF) degree of freedom. For example, if the modal amplitude DOF is node "2", and the J node of the gap element is node 42, and the constraint equation is number 2, then the constrain equation would be: CE,2,0,42,ux,1,2,emf,-1.

By using gap elements, you should be able to ramp your applied voltage or displacement loads and successfully pass through the pull-in voltage. You may need to increase the number of equilibrium iterations through the NEQIT command to several hundred in order to achieve a converged solution. You can monitor the gap status of the gap elements to see when the pull-in occurs. The DCVSWP command macro utilizes gap elements in order to pass through the pull-in voltage.

8.3.10. Apply Loads

You now apply loads. ROM144 supports the loads summarized in the following table.

Table 8.1:  ROM144 Loads

Load TypeDOFNode NumbersCommand
Modal AmplitudeEMF1–10 D
VoltageVOLT11–20 D
CurrentAMPS11–20 F
Nodal DisplacementUX21–30 D
Nodal ForceFX21–30 F

For convenience, a command macro DCVSWP has been created to execute a static analysis that is commonly performed. You can perform a DC voltage sweep up to a defined maximum voltage or up to a “pull-in” value. All conductors are set to ground except the sweep conductor.

Command(s): DCVSWP
GUI: Main Menu> Solution> ROM Tools> Voltage Sweep

Of course, you can specify an arbitrary analysis with complete arbitrary loading.

8.3.11. Specify Solution Options

All solution options described in the Structural Analysis Guide are valid for the ROM use pass. Some recommendations are:

  • Set the modal force (label CURT) convergence parameter (CNVTOL) to roughly 1E-6. Accuracy may depend on the value of this convergence parameter.

  • Coupled electromechanical systems are generally nonlinear; nevertheless, you can perform a prestressed modal or harmonic analysis for any static equilibrium state obtained with the application of structural or electrostatic loads. All system parameters are linearized as known from a small signal analysis. Activate prestress (PSTRES) and perform a static analysis prior to the modal or harmonic analysis.

  • You can use a prestress modal analysis to calculate the frequency shift due to stress stiffening or electrostatic softening. To run a modal analysis, activate the symmetric matrix option by setting KEYOPT(2) = 2 for the ROM element.

  • For a transient analysis, specify the full Newton-Raphson option (NROPT,FULL).

Usually the structural domain reacts with twice the frequency of the driving sinusoidal voltage time function. This is because electrostatic forces are quadratic functions of voltage. A harmonic analysis is only applicable if the polarization voltage in the preceding static analysis is much higher than the alternating voltage in the harmonic analysis.

A ROM solution will generate a reduced displacement results file (filename.rdsp).

8.3.12. Run ROM Use Pass

You then run the ROM use pass and exit the solution processor.

Command(s): SOLVE, FINISH
GUI: Main Menu> Preprocessor> Element Type> Add/Edit/Delete
Main Menu> Finish

8.3.13. Review Results

Review use pass results with POST1 and POST26. Results include modal amplitudes (EMF), conductor voltages (VOLT), nodal displacements (UX), and reaction solutions (AMPS, FX).


Release 18.2 - © ANSYS, Inc. All rights reserved.