8.5. Sample Miniature Clamped-Clamped Beam Analysis (Batch or Command Method)

8.5.1. Problem Description

Miniature clamped-clamped beams with dimensions in the micrometer range are widely used in MEMS. Typical examples are resonators for RF filters, voltage controlled micro switches, adjustable optical grating or test structures for material parameter extraction. Clamped-clamped beams can behave in a highly nonlinear fashion due to deflection dependent stiffening and stiffening caused by prestress. Both effects are very important for MEMS analysis and are illustrated by the following example.

Figure 8.8:  Clamped-Clamped Beam with Fixed Ground Conductor

Clamped-Clamped Beam with Fixed Ground Conductor

The half symmetry model uses hexahedral solid elements (SOLID185) for the structural domain and tetrahedral elements (SOLID122) for the electrostatic domain. The beam is fixed on both ends and symmetry boundary conditions are applied on the plane of intersection. The deflection to beam thickness ratio is more than 1 in order to realize essential stiffness change due to the stress stiffening effect.

Figure 8.9:  Finite Element Model of the Structural and Electrostatic Domains

Finite Element Model of the Structural and Electrostatic Domains

This example demonstrates nonlinear effects. First, the beam is considered as linear. The stress stiffening option is OFF. In the next case, stress stiffening is ON to model the real behavior. Finally, a 100 kPa biaxial prestress is applied. Initial prestress is modeled via thermal expansion in order to realize a nonuniform stress distribution at the clamp. Note that the uniaxial stress in the beam is different from the biaxial stress of the layer prior to release etching. The Generation Pass must be performed three times.

8.5.2. Program Listings

The following command input corresponds to the last case of a structure with initial prestress. Set TUNIF to zero in this file if initial prestress is not considered.

Model Input File:

/filnam,cbeam
/PREP7, Clamped-clamped beam with fixed ground electrode

! µMKSV system of units

! Model parameters

B_L=100                  ! Beam length
B_W=20                   ! Beam width
B_T=2                    ! Beam thickness
F_L=4                    ! Farfield in beam direction
F_Q=4                    ! Farfield in cross direction 
F_O=4                    ! Farfield above beam
E_G=4                    ! Electrode gap

sigm_b=-100

/VIEW,1,1,-1,1
/PNUM,TYPE,1
/NUMBER,1
/PBC,ALL,1

/PREP7

ET,1,SOLID185,,3         ! Structural domain
ET,2,SOLID122            ! Electrostatic domain

EMUNIT,EPZRO,8.85e-6     ! Free space permittivity
MP,PERX,2,1              ! Relative permittivity of air
                         ! Half symmetry
BLOCK,0,B_L,0,B_W/2+F_Q,-E_G,B_T+F_O    ! Entire domain
BLOCK,0,B_L,0,B_W/2,0,B_T               ! Structural domain
BLOCK,0,B_L,0,B_W/2,-E_G,0
VOVLAP,ALL

LSEL,S,LOC,X,B_L/2       ! Mesh density in axial direction
LESIZE,ALL,,,20,,1
LSEL,S,LOC,Y,B_W/4       ! Mesh density in transverse direction
LESIZE,ALL,,,2,,1
LSEL,S,LOC,Z,B_T/2       ! Mesh density in vertical direction
LESIZE,ALL,,,2,,1
LSEL,ALL
VSEL,S,LOC,Z,B_T/2       ! Mesh structural domain (mapped meshing)
VMESH,ALL
VSEL,ALL

SMRTSIZ,2
MSHAPE,1,3D
MSHKEY,0
TYPE,2
MAT,2
VMESH,4

LSEL,S,LOC,Y,b_w/2+f_q   ! Mesh density at bottom electrode 
LSEL,R,LOC,x,b_l/2
LESIZE,ALL,,,19,,1
LSEL,S,LOC,Y,0           ! Mesh density at bottom electrode 
LSEL,R,LOC,Z,b_t+f_o
LESIZE,ALL,,,19,,1
LSEL,S,LOC,Y,(b_w+f_q)/2
LESIZE,ALL,,,4,1/5,1
LSEL,ALL
VMESH,ALL

VSEL,S,LOC,Z,b_t/2       ! Movable electrode
ASLV,S,1
ASEL,U,LOC,Y,0
ASEL,U,LOC,X,0
ASEL,U,LOC,X,B_L
NSLA,S,1
CM,COND1A,AREA
CM,COND1,NODE            ! Conductor 1 node component
ALLSEL

ASEL,S,LOC,Z,-e_g        ! Fixed ground electrode
NSLA,S,1
CM,COND2A,AREA           
CM,COND2,NODE            ! Conductor 2 node component
ALLSEL

VSEL,U,LOC,Z,b_t/2       ! Region for DVMORPH
CM,AIR,VOLU              ! Default name 'AIR'
VSEL,ALL

ESEL,S,MAT,,1            
NSLE,S,1                 
NSEL,R,LOC,Z,b_t/2       
CM,NEUN,NODE             ! Neutral plane node component
ALLSEL


ET,1,0       
            
PHYSICS,WRITE,ELEC       ! Write electrostatic physics file
PHYSICS,CLEAR

ET,1,SOLID185,,3
ET,2,0

MP,EX,1,169e3            ! Material properties Si
MP,NUXY,1,0.066          ! <110>
MP,DENS,1,2.329e-15
MP,ALPX,1,1e-6

ASEL,S,LOC,Z,b_t/2
ASEL,R,LOC,Y,b_w/4
NSLA,S,1
CM,FIXA,AREA             ! Boundary condition must be 
DA,ALL,UX                ! applied on solid model entities
DA,ALL,UY
DA,ALL,UZ

ASEL,S,LOC,Z,b_t/2
ASEL,R,LOC,Y,0
NSLA,S,1
CM,BCYA,AREA
DA,ALL,UY
ALLSEL
FINI

/SOLU

tref,0
tunif,sigm_b*(1-0.066)/(169e3*1e-6)
FINI

PHYSICS,WRITE,STRU        ! Write structural physics file

ET,2,SOLID122             ! Plot the entire model
EPLOT

FINI

SAVE                      ! Save model database

Generation Pass:

No test load is defined. Hence the first modes in the operating direction will be used. There are two element loads: acceleration and a uniform pressure load. For initial prestress NLGEOM must be set ON and the loads must cause moderate displacements (in the range of 0.001 to 0.1 times the beam thickness).

/filnam,gener                 ! Jobname for the Generation Pass

rmanl,cbeam,db,,3,z           ! Assign model database, dimensionality, oper. direction
resu,cbeam,db                 ! Resume model database

rmcap,cap12,1,2               ! Define capacitance
rmclist                       ! List capacitances

rmaster,node(b_l/2,0,0)       ! Define master nodes
rmaster,node(b_l/4,0,0) 

                              ! Apply element loads
physics,clear
physics,read,STRU

/solu
antype,static
nlgeom,on
acel,,,9.81e12                ! Acceleration in Z-direction 9.81e6 m/s**2
lswrite,1
acel,0,0,0
esel,s,type,,1
nsle,s,1
nsel,r,loc,z,0
sf,all,pres,0.1               ! 100 kPa
allsel
lswrite,2
lssolve,1,2
fini

/post1                        ! Extract neutral plane displacements
set,1                         ! due to element loads
rmndisp,'eload','write'
set,2
rmndisp,'eload','append'
fini
 
physics,clear
physics,read,STRU
                             ! Perform prestressed modal analysis
/solu
nlgeom,off
pstress,on                    ! Thermal prestress (see cbeam.inp)
solve
fini

/solu
antype,modal              
modopt,lanb,9
mxpand,9
pstress,on
solve
fini

/post1                        ! Extract modal displacements at neutral
rmnevec                       ! plane nodes
fini

rmmselect,3,'nmod',-3.5,3.5   ! Automated mode selection

rmmlist				! List selected mode parameters

rmmrange,2,'UNUSED'           ! do not use unsymmetric mode for ROM

rmsave,cbeam,rom              ! Save ROM database

rmsmple,1                     ! nlgeom,on
rmporder,6,,2                 ! Set polynomial orders for modes 1 and 3

rmroption,sene,lagrange,0	! Specify response surface parameter
rmro,cap12,lagrange,1
                                
rmrgenerate			! Generate response surface

rmrstatus,sene			! Print status of response surface
rmrstatus,cap12

rmrplot,sene,func		! Plot response surface
rmrplot,cap12,func

rmsave,cbeam,rom              ! Save ROM database

rmlvscale,2,0,0               ! Necessary to consider element loads
                              ! in a VHDl-AMS model
rmxport                       ! Extract model input files for system simulation

Use Pass:

Calculation of voltage displacement functions up to pull-in

The following input was used for all three cases.

! *** Calculation of voltage displacement functions up to pull-in

/clear
/filnam,use1
rmresu,cbeam,rom

/PREP7
ET,1,144

*do,i,1,20
n,i
*enddo

rmuse,on
e,1,2,3,4,5,6,7,8
emore,9,10,11,12,13,14,15,16
emore,17,18,19,20
FINISH

/gst,off

DCVSWP,'pi',1,2,1200,10,1         ! Run voltage sweep up to Pull-in voltage

The pull-in results for the three cases are as follows:

  • Linear analysis: 992 volts

  • Nonlinear analysis (stress stiffening is ON): 1270 volts

  • Initial prestress analysis: 1408 volts

Connecting other elements to ROM144

The structure is driven by a voltage sweep to the contact pad placed at the center of the micro beam. A gap element (COMBIN40) connects to the center of the beam at a master node (node 21). It has a contact stiffness of 1.E6 N/m and an initial gap of 0.3 µm. The UX degree of freedom tracks the master node displacement (actual displacement is in the Z-direction). Similar models can simulate voltage controlled micro switches.

! *** Connecting other elements to ROM144

/clear
/filnam,use2
rmresu,cbeam,rom

/PREP7
ET,1,144,1

*do,i,1,30
n,i
*enddo

rmuse,on
e,1,2,3,4,5,6,7,8
emore,9,10,11,12,13,14,15,16
emore,17,18,19,20,21,22,23,24
emore,25,26,27,28,29,30

et,2,40,0,0
r,2,1e6,,,.3

type,2
real,2
n,31
e,31,21
fini

/gst,off

/solu
antyp,static
outres,all,all
cnvtol,curt,1.0d-6,,2            ! Set modal force convergence criteria
d,11,volt,1000
d,12,volt,0                  
d,31,ux,0
kbc,0
nsubst,10
solve
fini

/post26
nsol,2,21,ux,,mast1              ! Master node displacements
nsol,3,22,ux,,mast2
plvar,2,3
nsol,5,1,emf,,mode1              ! Modal displacements
nsol,6,2,emf,,mode2
nsol,7,3,emf,,mode3
plvar,5,6,7
esol,8,1,,nmisc,1,sener          ! Strain energy
esol,9,1,,nmisc,2,cap12          ! Capacitance
plvar,8
plvar,9
fini

Release 18.2 - © ANSYS, Inc. All rights reserved.