3.4. Sample Electrostatic Actuated Beam Analysis (Batch or Command Method)

3.4.1. Problem Description

A clamped beam for an RF MEMS switch device is modeled to compute the center deflection for an applied voltage. Forces generated by the electrostatic field will bend the beam towards a ground plane.

SOLID185 brick elements model the beam. A half-width model is constructed with symmetry boundary conditions placed at the plane of symmetry. The beam is clamped at both ends. A surface interface flag (FSIN) is placed on the bottom beam surface. NLGEOM is set for geometric nonlinearities (large deflection and stress stiffening).

SOLID123 tetrahedral elements model the air underneath the beam. Fringing effects are ignored for simplicity. (Fringing effects may be considered by extending the model for the electrostatic domain beyond the boundary of the beam.) A surface interface flag (FSIN) is placed at the top of the electrostatic domain coincident with the structural beam mesh. The morphing command is activated (MORPH,on) to enable the application of structural boundary conditions at the periphery of the electrostatic domain. This is done to prepare the electrostatic domain for mesh movement (morphing) during the coupled field solution. Voltages are applied at the top and bottom surface of the electrostatic domain. A plot of the structural and electrostatic elements is shown in Figure 3. Note that the meshes are dissimilar at the interface between the domains.

The structure model is defined as field number 1; the electrostatic model is defined as field number 2 (MFELEM). Analysis options are defined for both field solutions and written to files (MFCMMAND). A static solution is defined for both fields. For the electrostatic model, 120 volts is applied with a ramped boundary condition (KBC) at 10 volt solution intervals (DELTIM). The field order for the solution is set to solve the electrostatic field first, followed by the structural field (MFORDER). The "time" is set to 120 (MFTIME) to correspond to the voltage level (for convenience) with ANSYS Multi-field solver solutions requested at 10 volt intervals (MFDTIME). Up to 20 stagger iterations are defined (MFITER). Globally conservative load transfer is prescribed (MFINTER). Forces are transferred from the electrostatic domain to the structural domain (MFSURFACE). Displacements are transferred from the structural domain to the electrostatic domain for use in morphing of the electrostatic mesh (MFSURFACE).

Figure 3.22:  Structural and Electrostatic Field Mesh

Structural and Electrostatic Field Mesh

3.4.2. Results

The total number of cumulative iterations for 12 converged ramped solutions was 153 (due to geometric nonlinearities in the structural field). Results for each field are stored in separate results files. Each field is postprocessed individually.

Figure 3.23:  Beam Displacement for 120 Volt Load

Beam Displacement for 120 Volt Load

Figure 3.24:  Electrostatic Field

Electrostatic Field

Figure 3.25:  Mid-span Beam Deflection vs Voltage

Mid-span Beam Deflection vs Voltage

3.4.3. Command Listing

The command listing below demonstrates the problem input. Text prefaced by an exclamation point (!) is a comment.

/title, Electrostatic clamped beam analysis
/com, ANSYS Multi-field solver
/com, globally conservative Load transfer
/com, Structure: SOLID185 brick elements
/com, Electrostatic: SOLID123 tetrahedral elements
/com, uMKSV units

bl=150                  ! beam length, um
bh=2                    ! beam height, um
bw=4                    ! beam width, um
gap=2                   ! gap, um

/prep7

! Structural model

et,1,185,,3             ! 8-node bricks, simplified enhanced strain
mp,ex,1,169e3           ! kg/(um)(s)^2
mp,nuxy,1,0.066
mp,dens,1,2.329e-15     ! kg/(um)^3

block,0,bl,0,bh,0,bw    ! structural volume
aslv
lsla
lsel,r,loc,x,bl/2
lesize,all,,,20,,,,1    ! 20 bricks along bl
lsla
lsel,r,loc,y,bh/2
lesize,all,,,2,,,,1     ! 2 bricks along bh
lsla
lsel,r,loc,z,bw/2
lesize,all,,,1,,,,1     ! 1 brick along bw
vatt,1,,1       
vmesh,all
alls
asel,s,loc,y,bh/2       ! clamp beam ends
asel,r,loc,z,bw/2
nsla,s,1
da,all,ux
da,all,uy
da,all,uz
alls
asel,s,loc,y,bh/2       ! symmetry plane
asel,r,loc,z,0
nsla,s,1
da,all,uz
alls
nsel,s,loc,y,0
sf,all,fsin,1           ! Define Surface interface

! Electrostatics model
et,2,123
emunit,EPZRO,8.854e-6   ! pF/um
mp,perx,2,1
morph,on                ! enable morph bc's
block,0,bl,-gap,0,0,bw  ! electrostatic volume
vsel,s,volu,,2
smrtsiz,2
mshape,1,3D		
mshkey,0		
vatt,2,,2
vmesh,all
aslv,s
asel,r,loc,x,0
da,all,ux,0             ! Apply structural morphing constraints	
aslv,s
asel,r,loc,x,bl
da,all,ux,0
aslv,s
asel,r,loc,z,0
da,all,uz,0
aslv,s     
asel,r,loc,z,bw
da,all,uz,0
aslv,s
asel,r,loc,y,-gap
da,all,uy,0
aslv,s
asel,r,loc,y,0
nsla,s,1                     
sf,all,fsin,1           ! Define Surface interface
d,all,volt,120          ! Apply voltage	
nsel,s,loc,y,-gap
d,all,volt,0            ! Apply ground potential
allsel,all
fini

/solu
mfan,on                 ! Activate ANSYS Multi-field solver analysis 
mfel,1,1                ! structure field
mfel,2,2                ! electrostatic field
mfor,2,1                ! Order for field solution
mfco,all,1.0e-5         ! Convergence settings
antyp,stat
eqslv,iccg
morph,on
mfcm,2,                 ! Electrostatic field analysis options
antyp,stat
nlgeom,on
deltim,10               ! Field loop time increment within a stagger
morph,off
kbc,0                   ! Ramp voltage load
mfcm,1                  ! Structural field analysis options
mfti,120                ! End time
mfou,1                  ! Write solution every time step
mfdt,10                 ! Stagger time increment
mfit,20                 ! Max staggers
mfint,cons              ! globally conservative load transfer
mfsu,1,2,forc,1         ! Transfer forces to structure field
mfsu,1,1,disp,2         ! Transfer displacements to electrostatic field
solve                   ! Solve the ANSYS Multi-field solver problem
save
finish

/post1
file,field2,rth         ! Select Electrostatic Field results file
set,last
esel,s,type,,2          ! Select electrostatic elements
plns,ef,sum             ! Plot electrostatic field
fini
/post1
file,field1,rst         ! Select Structural Field results file
set,last
esel,s,type,,1          ! Select structural elements
nsle,s
plns,u,y                ! Plot displacement
prdisp
finish

/post26                 ! Time-histroy postprocessor
file,field1,rst         ! Retrieve Structural Field results file
n1=node(75,0,0)         ! get node at mid-plane
nsol,2,n1,u,y           ! store UY displacement vs. voltage
/axlab,y,UY             ! Displacement
/axlab,x,Voltage        ! Time = voltage
prvar,2                 ! print displacement vs. voltage
plvar,2                 ! plot displacement vs. voltage
fini

Release 18.2 - © ANSYS, Inc. All rights reserved.