A thick-walled cylinder is maintained at a temperature Ti on the inner surface and To on the outer surface. The temperature distribution in the cylinder and the axial and hoop stresses at the inner surface are determined. See Mechanical APDL Verification Manual problem VM32 Thermal Stresses in a Long Cylinder for a similar problem.
A quarter-cylinder model is chosen to demonstrate the thermal-stress analysis using a dissimilar mesh between the thermal and structural models. SOLID87 elements model the thermal response while SOLID186 elements model the structural response.
The thermal model is constructed first. Temperature constraints are applied to the inner and outer surface. The structural model is constructed next. Constraints are applied to simulate symmetry boundary conditions. In the z-direction, one face is constrained while the other face has the UZ degree of freedom for the nodes coupled to simulate an infinitely long cylinder.
A volumetric load transfer flag is set for all the elements since the mesh for the thermal and structural models completely overlap.
In the solution phase, the model is set up to use the ANSYS Multi-field solver (MFANALYSIS). The thermal analysis is identified as field #1, assigning the thermal element type to that field (MFELEM). In a similar fashion, the structural analysis is identified as field #2 with the structural element type assigned to that field. Since this is a static analysis, the time is set to 1.0 (MFITER) with a single time increment (MFDTIME). Relaxation of the transferred load quantities is set to 0.5 (MFRELAX).
Field file names are assigned which will be used in the naming of the results files (MFFNAME). A volumetric load transfer is defined which will send temperatures from the thermal field to the structural field (MFVOLUME). Analysis options are set for the thermal solution and written to a command file (MFCMMAND). Similarly, analysis options are set for the structural solution and written to a command file. The solution is then performed.
The following figure illustrates the thermal and structural mesh.
The following figure illustrates the thermal solution and the axial stress.
The analytic solution for both the hoop and axial stress is 420.24 at the inner cylinder wall. The ANSYS results are shown in the following table.
Table 3.4: Hoop and Axial Stress Variation
| Stress Component | Min Value | Max Value |
|---|---|---|
| Hoop Stress | 418.3 | 418.9 |
| Axial Stress | 421.5 | 421.7 |
The command listing below demonstrates the problem input. Text prefaced by an exclamation point (!) is a comment.
/TITLE, Thermal stress analysis of a long thick cylinder /com, Reference: Verification Manual Problem VM32 /com, /com,****************** Characteristics ******************************* /com, /com, Thermal Element: SOLID87 /com, Structural Element: SOLID186 /com, /com,******************** Expected results **************************** /com, /com, At inner radius: Axial and hoop stress = 420.42 /com, /com,****************************************************************** /com, ir=.1875 ! Cylinder inner radius or=.625 ! Cylinder outer radius theta=90 ! Angle for partial cylinder model h=.5 /prep7 ! Thermal model et,1,87 ! Thermal element type mp,kxx,1,3 ! Conductivity cylind,ir,or,0,h,0,theta ! Build thermal model esiz,,6 vmesh,all ! Free tetrahedral mesh csys,1 nsel,s,loc,x,ir d,all,temp,-1 ! Set inner wall temperature nsel,s,loc,x,or d,all,temp,0 ! Set outer wall temperature allsel,all ! Structure Model et,2,186,,1 ! Structural element type mp,ex,2,30E6 ! Structural properties mp,alpx,2,1.435E-5 mp,nuxy,2,.3 cylind,ir,or,0,h,0,theta ! Build structural model esiz,,9 vatt,2,1,2 vmesh,all ! Mapped brick mesh csys,0 esel,s,type,,2 nsle nsel,r,loc,z d,all,uz,0 ! Set structural bc's nsle nsel,r,loc,z,h cp,1,uz,all nsle nsel,r,loc,y d,all,uy,0 nsle nsel,r,loc,x d,all,ux,0 allsel,all bfe,all,fvin,,1 ! Volumetric Flag for load transfer finish /solu mfan,on ! Activate MFS analysis mfel,1,1 ! Field #1: Thermal mfel,2,2 ! Field #2: Structure mfor,1,2 ! Field order (thermal, structure) mfti,1 ! Time at end of analysis mfdt,1 ! One field loop within a stagger mfit,5 ! Max 5 stagger loops mfre,all,0.5 ! Field transfer relaxation parameter mffn,1,therm1 ! Field #1 filename mffn,2,struc2 ! Field #2 filename mfvo,1,1,temp,2 ! Volumetric load transfer (temp to structure) antyp,stat eqslv,iccg mfcm,1 ! Write thermal analysis options antype,static eqslv,pcg mfcm,2 ! Write structure analysis options solve finish /post1 file,therm1,rth ! Thermal results file set,last esel,s,type,,1 ! Select thermal elements plns,temp ! Plot temperatures finish /post1 file,struc2,rst ! Structure field results file set,last esel,s,type,,2 ! Select structural elements rsys,1 ! set result for cylindrical c.s. csys,1 nsel,s,loc,x,ir ! select nodes at inner radius nsort,s,z ! sort z-stress *get,szmax,sort,,max ! get max and min values *get,szmin,sort,,min nsort,s,y ! sort hoop stress *get,symax,sort,,max ! get max and min values *get,symin,sort,,min *status ! show max/min values nsel,all plns,s,z ! Plot z-axis stress finish