2.6. C*-integral Calculation

C*-integral is used to evaluate the crack tip fields in a homogenous material undergoing a secondary (steady-state) creeping deformation. C* is obtained by replacing the displacements with velocities, and the strain energy density with the strain energy rate density in the J-integral expansion.

To obtain path-independent C*-integral values, the creep deformation must be fully developed (that is, the creep strains should dominate the elastic strains in a region near the crack tip).

The following topics concerning C*-integral calculation are available:

For a list of supported elements, see Table 2.1: Element Support for Fracture-Parameter Calculation.

Also see C*-integral Evaluation for 3-D Surface Flaws in the Mechanical APDL Technology Demonstration Guide.

2.6.1. C*-integral Calculation with the Domain Integral Method

For a 2-D problem, and in the absence of thermal strain, body forces within the integration of area, and pressure on the crack surface, the domain integral representation of the C*-integral is given in C*-integral. For more information about the domain integral method, see J-integral Calculation.

The discretized form of the C*-integral is given by:

where is the number of elements to be integrated, is the weight function, and is the area of the element represented by .

For higher-order elements (such as PLANE183 and SOLID186), the vector at midside nodes takes the averaged values from the corresponding corner nodes.

If the thermal strains exist in the structure and the surface tractions act on crack faces, the C*-integral is expressed as:

where is the thermal expansion coefficient, is the crack face traction, and is crack face upon which the tractions act.

For a 3-D problem, domain integral representation of the C*-integral becomes a volume integration, which again is evaluated over a group of elements. The implementation becomes more complicated; however, the principal is similar to that of the 2-D problem.

2.6.2. Material Behavior

C*-integral evaluation supports secondary (steady-state) creep material behavior. For more information, see Creep in the Material Reference.

2.6.3. Calculating C*-integral

The program calculates the C*-integral at the solution phase of the analysis after a substep has converged, then stores the value in the results file.

To start a C*-integral calculation, use the CINT command's NEW option and provide a numerical identifier for the input information for the calculation, as follows:

CINT,NEW,n

CINT,TYPE,CSTAR

where n is the number identifying this C*-integral calculation.

Example 2.32:  Initiating a C*-integral Calculation
CINT,NEW,1       ! initiate a new C*-integral calculation
!                     as # 1 
CINT,TYPE,CSTAR  ! set its type as CSTAR

All CINT command options available for J-integral calculation are also available for C*-integral.

Example 2.33:  C*-integral Evaluation

Following is a C*-integral evaluation for a crack in a homogenous material with symmetry conditions imposed:

! local coordinate systems
local,11,0,,,,
! …

CINT,NEW,1
CINT,TYPE,CSTAR
CINT,CENC,CRACK_FRONT_NODE_SET,,11,2
CINT,SYMM,ON   ! crack 1 is a symmetrical crack
CINT,NCON,5
OUTRES,CINT,10  ! output C*-integral every 10 substeps


Release 18.2 - © ANSYS, Inc. All rights reserved.