2.2. VCCT Energy-Release Rate Calculation

The approach for evaluating the energy-release rate is based on the virtual crack-closure technique (VCCT). The energy-release rate calculation occurs during the solution phase of the analysis and the results are saved for postprocessing.

The following energy-release rate calculation topics are available:

For a list of supported elements, see Table 2.1: Element Support for Fracture-Parameter Calculation.

2.2.1. Using VCCT for Energy-Release Rate Calculation

VCCT is based on the assumption that the energy needed to separate a surface is the same as the energy needed to close the same surface. The implementation described here uses the modified crack-closure method (a VCCT-based method) and assumes further that stress states around the crack tip do not change significantly when the crack grows by a small amount (Δa).

2.2.1.1. 2-D Crack Geometry

For 2-D crack geometry with a low-order element mesh, the energy-release rate is defined as:

where:

GI and GII = mode I and II energy-release rate, respectively
Δu and Δv = relative displacement between the top and bottom nodes of the crack face in local coordinates x and y, respectively
Rx and Ry = reaction forces at the crack-tip node
Δa = crack extension, as shown in the following figure:

Figure 2.1:  2-D Crack Geometry Schematic

2-D Crack Geometry Schematic

2.2.1.2. 3-D Crack Geometry

For 3-D crack geometry with a low-order element mesh, the energy-release rate is defined as:

where:

GI, GII, and GIII = mode I, II, and III energy-release rate, respectively
Δu, Δv, and Δw= relative displacement between the top and bottom nodes of the crack face in local coordinates x, y, and z, respectively
Rx, Ry, and Rz = reaction forces at the crack-tip node
ΔA = crack-extension area, as shown in the following figure:

Figure 2.2:  3-D Crack Geometry Schematic

3-D Crack Geometry Schematic

2.2.1.3. Mesh and Material Behavior

In most cases, ANSYS, Inc. recommends using linear elements including PLANE182 and SOLID185.

The accuracy of the VCCT calculation depends on the meshes. To ensure the greatest accuracy, use equal element sizes ahead of and behind the crack-tip node. The mesh size affects the solution; therefore, it is helpful to examine mesh-size convergence prior to attempting the finite element solution.

When calculating energy release rates (CINT,TYPE,VCCT), the mesh in the vicinity of the crack must contain only hex- (3-D) or quad- (2-D) shaped elements. The VCCT option does not support degenerative element shapes.

The VCCT method for energy-release rate calculation supports the following material behaviors:

  • Linear isotropic elasticity

  • Orthotropic elasticity

  • Anisotropic elasticity

2.2.2. Performing the Energy-Release Rate Calculation

The CINT command's VCCT option initiates the energy-release rate calculation.

Similar to the J-integral calculation, CINT specifies the parameters necessary for the calculation.

For CINT element-type and material-behavior support, see Material Behavior.

2.2.2.1. Step 1: Initiate a New Energy-Release Rate Calculation

Issue the CINT command twice, as shown:

CINT,NEW,n

CINT,TYPE,VCCT

where n is the identifier for this energy-release rate calculation (for example, 1).

2.2.2.2. Step 2: Define Crack Information

Similar to the J-integral calculation, the crack-tip node component and the crack-extension direction are both necessary for the energy-release rate calculation.

VCCT requires the finite element mesh to be in the crack-extension direction. To ensure the accuracy of the energy-release rate calculation, it is crucial that you correctly define the crack extension. How you do so depends upon whether the crack plane is flat or not:

2.2.2.2.1. Specifying Crack Information When the Crack Plane Is Flat

This approach applies to both 2-D crack geometry and 3-D flat crack surfaces. It offers a simple way to define a 3-D energy-release rate calculation, as you need only define the crack-tip (front) node component and the normal of the crack plane.

2-D Flat Crack Geometry

For 2-D crack geometry, define a crack-tip node component (usually a node located at the crack tip). You can also define a group of nodes around the crack tip, including the node at the crack tip. The program uses this group of nodes to form the necessary information for the VCCT calculation automatically.

3-D Flat Crack Geometry

For 3-D flat crack surfaces, define a crack-tip node component that includes all of the nodes along the crack front. At each node location, however, only one node can exist.

All nodes in the crack-tip node component must be connectable, and they must form a line based on the element connectivity associated with it. This line is the crack front. The program uses it to determine the elements and the nodes needed for the VCCT calculation automatically.

VCCT is not applicable in the case of a collapsed crack-tip mesh.

The command syntax is:

CINT,CTNC,Par1,Par2,Par3

where CTNC specifies a crack-tip node component, Par1 is the crack-tip node component name, Par2 is the crack-extension direction calculation-assist node (any node on the open side of the crack), and Par3 is the crack front’s end-node crack-extension direction override.

The Par1 and Par2 values help to identify the crack-extension direction. Although the program automatically calculates the energy-release rate at the crack tip using the local coordinate system, it is usually best to use Par2 to define a crack face node to help align the extension directions of the crack-tip nodes.

By default, the program uses the external surface to determine the crack-extension direction and normal when the crack-tip node hits the free surface. You can use Par3 to override this default.

After the crack-tip node component is defined, define the normal of the crack plane. The program automatically converts it into the crack-extension vector q, based on the element information. The crack-extension vector is taken along the perpendicular direction to the plane formed by the crack-plane normal and the tangent direction of the crack-tip node, and is normalized to a unit vector.

The command syntax is:

CINT,NORM,Par1, Par2

where Par1 is the coordinate system number and Par2 is the coordinate system axis.

Example 2.9:  Specifying Crack Information
!   Local coordinate system
LOCAL,11,0,,,,
! select nodes located along the crack front and 
! define it as crack front/tip node component
NSEL,S,LOC,X,Xctip
NSEL,R,LOC,Y,Yctip
CM,CRACK_TIP_NODE_CM

!   Define a new the energy-release rate calculation
CINT,NEW,1
CINT,TYPE,VCCT
CINT,CTNC,CRACK_TIP_NODE_CM
CINT,NORM,11,2

Example 2.10:  Specifying Crack Information
!   Select nodes located along the crack front and 
!      define it as crack front/tip node component
LSEL,,,,
NSLL
CM,CRACK_FRONT_NODE_CM,NODE
CINT,NEW,1
CINT,TYPE,VCCT
CINT,CTNC,CRACK_FRONT_NODE_CM

2.2.2.2.2. Specifying Crack Information When the Crack Plane Is Not Flat

This approach applies to 3-D curved crack planes, where a unique normal may not exist. However, you must define the crack-extension node component and the crack-extension direction at each crack-tip node location:

  1. Define a node component consisting of one or more nodes forming the crack tip.

    The node component can have one or more nodes.

    Example: CINT,CENC,ComponentName

  2. If the node component has more than one node, identify the crack-tip node separately.

    If a crack-tip node is not identified, the first node of the node component is used as the first node.

    Example: CINT,CENC,ComponentName,Node1

  3. Define the crack-extension direction.

    Identify the local coordinate system associated with the crack under consideration, and identify the local axis along which the crack should extend.

    Example: CINT,CENC,ComponentName,Node1,11,2

    Alternatively, define the crack-extension direction by directly specifying the global X, Y, and Z components of the crack-extension vector.

    Example: CINT,CENC,ComponentName,Node1,,,compx,compy,compz

Repeat this method for all node locations along the crack front. Although the program automatically calculates the local coordinate system at the crack tip to determine the energy-release rate, it is usually best to use the NORM option to help align the calculated normals of the crack-tip nodes.

Example 2.11:  Specifying Crack Information When the Crack Plane Is Not Flat
!   Local coordinate systems
local,11,0,,,,
local,12,0,,,,
! …
local,n,0,,,,

NSEL,S,LOC,X,Xctip1
NSEL,R,LOC,Y,Yctip1
NSEL,R,LOC,Z,Zctip1
CM,CRACK_FRONT_NODE_CM1
NSEL,S,LOC,X,Xctip2
NSEL,R,LOC,Y,Yctip2
NSEL,R,LOC,Z,Zctip2
CM,CRACK_FRONT_NODE_CM2
! …
NSEL,S,LOC,X,Xctipn
NSEL,R,LOC,Y,Yctipn
NSEL,R,LOC,Z,Zctipn
CM,CRACK_FRONT_NODE_CMn

CINT,NEW,1
CINT,TYPE,VCCT
CINT,CENC,CRACK_FRONT_NODE_CM1,,11,2
CINT,CENC,CRACK_FRONT_NODE_CM2,,12,2
! …
CINT,CENC,CRACK_FRONT_NODE_CMn,,n,2

Example 2.12:  Specifying Crack Information When the Crack Plane Is Not Flat
!   Crack-extension node component and
!     crack-extension direction specification using vectors
NSEL,S,LOC,X,Xctip1
NSEL,R,LOC,Y,Yctip1
NSEL,R,LOC,Z,Zctip1
CM,CRACK_FRONT_NODE_CM1
NSEL,S,LOC,X,Xctip2
NSEL,R,LOC,Y,Yctip2
NSEL,R,LOC,Z,Zctip2
CM,CRACK_FRONT_NODE_CM2
! …
NSEL,S,LOC,X,Xctipn
NSEL,R,LOC,Y,Yctipn
NSEL,R,LOC,Z,Zctipn
CM,CRACK_FRONT_NODE_CMn

CINT,NEW,1
CINT,TYPE,VCCT
CINT,CENC,CRACK_FRONT_NODE_CM1,,,,Vx1,Vy1,Vz1
CINT,CENC,CRACK_FRONT_NODE_CM2,,,,Vx2,Vy2,Vz2
! …
CINT,CENC,CRACK_FRONT_NODE_CMn,,,,Vxn,Vyn,Vzn

Local Crack-Tip Coordinate System

The VCCT calculation is based on the local crack-tip coordinate systems. To ensure the accuracy of the energy-release rate calculation, it is crucial to have a local crack-tip coordinate system in which the local x axis is pointed to the crack extension, the local y axis is pointed to the normal of the crack surfaces or edges, and the local z-axis pointed to the tangential direction of the crack front.

Local coordinate systems must be consistent across all nodes along the crack front. A set of inconsistent coordinate systems results in irregular behavior of the energy-release rate distribution along crack front.

The program automatically calculates the local coordinate systems based on the input crack front nodes and the normal of the crack surface or extension directions. Because there may be not enough information to determine a set of consistent coordinate systems, however, ANSYS, Inc. recommends:

  • Using the CINT command's CTNC option to define a crack-face node to help identify the coordinate systems, or

  • Using the CINT command's NORM option, followed by the CENC option, to define the coordinate systems.

2.2.2.3. Step 3: Define a Crack Symmetry Condition

If the crack is located along a symmetry plane, and only a half model is created, define a symmetric condition so that the program can account for it. To do so, issue the following command:

CINT,SYMM,ON

Example 2.13:  Defining a Crack Symmetry Condition
CINT,NEW,1
CINT,TYPE,VCCT
CINT,SYMM,ON   ! crack 1 is a symmetrical crack

2.2.2.4. Step 4: Specify Output Controls

Similar to the J-integral calculation, the program calculates the energy-release rate during the solution phase of the analysis and stores the results in the .rst file for postprocessing.

Energy-release rate output uses all of the defaults from the OUTRES command. The OUTRES,ALL command includes CINT command results. However, you can issue an OUTRES,CINT command to control the specific output for energy-release rate results only.

Example 2.14:  Specifying Output Controls
CINT,NEW,1
CINT,TYPE,VCCT
CINT,CTNCP,CRACK_TIP_NODE_CM
CINT,SYMM,ON
OUTRES,CINT,10   ! output CINT results every 10 substeps


Release 18.2 - © ANSYS, Inc. All rights reserved.