The following topics related to T-stress calculation are available:
For a list of supported elements, see Table 2.1: Element Support for Fracture-Parameter Calculation.
The T-stress parameter is calculated using an interaction integral similar to the one used for the stress-intensity factors calculation. The auxiliary solution used is the solution of a line load of magnitude f applied along the crack front in the direction of the crack plane [12][13]:
In practice, the magnitude of f is typically 1.
The T-stress itself is extracted from the interaction integral result I as follows:
where:
| T = obtained T-stress value |
| E = Young’s modulus |
| ν = Poisson’s ratio |
| ε33= extensional strain at the crack front in the direction tangential to the front |
T-stress evaluation supports the following material behavior:
Linear isotropic elasticity
Even if isotropic plasticity behavior is supported, stress-intensity factors and T-stress are strictly valid under the small-scale yielding assumption; therefore, the crack tip plastic zone must be small. In practice, the crack tip plastic zone must always be smaller than the last CINT integration contour so that the interaction integral is calculated on elements that still exhibit a linear elastic behavior.
T-stress evaluation does not support:
Pressure on cracks faces, body force, body temperature, and initial strains
Axisymmetric problems
To start a T-stress calculation, issue the CINT command twice, as follows:
CINT,NEW,n
CINT,TYPE,TSTRESS
where n is the T-stress calculation ID number.
All CINT command options available for stress-intensity factor calculation are also available for T-stress.
Following is a full setup of a T-stress evaluation using the node component CRACK_TIP_NODE_CM to define the crack front, a symmetry condition, and five integration contours:
CINT,NEW,1 CINT,TYPE,TSTRESS CINT,CTNC,CRACK_TIP_NODE_CM CINT,SYMM,ON CINT,NCON,5
For more information about the calculation setup procedure, see Calculating the Stress-Intensity Factors.