2.3. Discrete Elements

2.3.1. COMBI165 Spring-Damper

Spring elements generate a force which depends on displacement; that is, change of length of the element. The force is applied along the element axis. For example, a positive force (tension) acts along the positive axis direction on node 1 and along the negative axis direction on node 2. By default, the element axis lies along the line from node 1 to node 2. When the element rotates, the line of action of the force also rotates.

Damper elements are treated as a subset of spring elements: both linear viscous and nonlinear viscous dampers can be modeled.

Rotational (torsional) springs and dampers are also available. These are selected by setting KEYOPT(1) = 1. The rest of the input is the same as for translational springs; the given force-displacement relationship will be treated as moment-rotation (rotation in radians), and the moments are applied about the element axis (positive clockwise). Rotational springs affect only the rotational degrees of freedom of their nodes - they do not pin the nodes together.

The COMBI165 element can be used in combination with any other explicit element. However, because it does not have mass, COMBI165 cannot be the only element type in an analysis. To represent a spring/mass system, you must add mass by also defining MASS166 elements.

You cannot define both spring and damper properties for the same COMBI165 element. However, you can define separate spring and damper elements that use the same nodes (that is, you can overlay two COMBI165 elements).

You can use any of the following material models for COMBI165:

  • Linear Elastic Spring

  • Linear Viscous Damper

  • Elastoplastic Spring

  • Nonlinear Elastic Spring

  • Nonlinear Viscous Damper

  • General Nonlinear Spring

  • Maxwell Viscoelastic Spring

  • Inelastic Tension or Compression-Only Spring

When using COMBI165, be sure to specify a unique set of real constants, element type, and material properties (R, ET, and TB commands, respectively) for each part to ensure that parts are uniquely defined.

2.3.2. MASS166

The mass element is defined by a single node and a mass value (Force*Time2/Length). Mass elements can often be used in a model to realistically characterize the mass of a structure without incorporating a large number of solid or shell elements. In an automobile impact analysis, for example, mass elements can model engine components whose deformation behavior is not of primary interest. Such a use of mass elements will reduce the number of elements required in an analysis, hence reducing the total computation time required to obtain a solution.

You can also use the MASS166 element to define a lumped rotary inertia at a node. To use this option, set KEYOPT(1) = 1 in the MASS166 element definition and input six moment of inertia values (IXX, IXY, IXZ, IYY, IYZ, IZZ) via the element real constants. You can not input a mass value for this option; therefore, you must define a second mass element at the same node (with KEYOPT(1) = 0) to account for mass.


Release 18.2 - © ANSYS, Inc. All rights reserved.