4.6. Dynamic Relaxation

In order to conduct implicit-to-explicit sequential solutions (see Implicit-to-Explicit Sequential Solution), dynamic relaxation capability has been added to the ANSYS LS-DYNA program (EDDRELAX command). True dynamic relaxation (EDDRELAX,DYNA) allows an explicit solver to conduct a static analysis by increasing the damping until the kinetic energy drops to zero. When an implicit solver is used to provide the preload (EDDRELAX,ANSYS), a slightly different approach is taken, in that the stress initialization is based on a prescribed geometry (i.e., the nodal displacement results from the implicit solution). In this latter case, the explicit solver only uses 101 time steps to apply the preload. In the former case, the solver will check the kinetic energy every 250 cycles (by default) until the kinetic energy from the applied preload is dissipated. ANSYS LS-DYNA supports both methods, which occur in pseudo time before the transient portion of the analysis begins at time zero. The EDLOAD command specifies the analysis type through the PHASE label.

EDLOAD , ADD, Lab, , Cname, Par1, Par2, PHASE

PHASE:0Load curve for transient analysis only (default) or for implicit-to-explicit sequential solutions
 1Load curve for dynamic relaxation only
 2Load curve for both transient and dynamic relaxation analyses

There are essentially five different types of analyses that can be conducted with ANSYS LS-DYNA concerning dynamic relaxation. They are discussed below:

  1. Transient Dynamic Analysis Only (default - EDDRELAX,OFF): In this case, the PHASE parameter of the EDLOAD command is set to zero and dynamic relaxation is not used. This is the default setting.

  2. Stress Initialization Only with No Transient Analysis (EDDRELAX,DYNA): This case basically uses the ANSYS LS-DYNA explicit solver to approximate the solution of a static analysis that is really best handled by an implicit solver such as ANSYS. The PHASE parameter on the EDLOAD command is set to one. The termination time (TIME command) must be set to zero to prevent unloading of the static load. True dynamic relaxation is used.

  3. Stress Initialization with a No-Load Transient Analysis (EDDRELAX,DYNA): This case is the same as the previous case, except that the termination time is set to the desired value. At time zero, the structure is instantly unloaded and free to vibrate.

  4. Stress Initialization with a Loaded Transient Analysis (EDDRELAX,DYNA): This is similar to the previous case, except that the load curve specified by the EDLOAD command (via PHASE = 2) will be used in both pseudo time for the dynamic relaxation to obtain the preload and in real time for the transient analysis. If a ramped load curve is used instead of a constant load curve, then the structure will unload at time zero and reload again. Therefore, if a ramped load curve is needed for the explicit solver to accurately converge on the static solution, it would be better to use two EDLOAD commands, the first (with PHASE = 1) to apply the preload using a ramped load curve and the second (with PHASE = 0) to continue the load with a load curve that is not ramped.


    Note:  If you issue EDLOAD multiple times for the same component (or Part ID) and the same load label, the values associated with the last EDLOAD command are used. Consequently, you cannot use multiple values of the PHASE parameter for a given component (or Part ID) and load label. To work around this limitation, you must use duplicate nodal components for the stress initialization and transient curves. (This workaround is applicable only if you use components to define the load.)


  5. Implicit-to-Explicit Sequential Solutions (EDDRELAX,ANSYS): This case uses the displacement results from the ANSYS implicit solver to apply the preload for the ANSYS LS-DYNA explicit solver via stress initialization to a prescribed geometry. The PHASE parameter on the EDLOAD command must be set to zero. This scenario is explained in detail in Implicit-to-Explicit Sequential Solution of this guide. Fields 2-6 of the EDDRELAX command are ignored for this case.


Release 18.2 - © ANSYS, Inc. All rights reserved.