4.5. Temperature Loading

You may need to define temperature loading in an explicit dynamic analysis in order to accommodate temperature dependent materials, or to include the effects of thermally induced stresses. Temperature loading is applicable to the PLANE162, SHELL163, SOLID164, and SOLID168 element types. The ANSYS LS-DYNA program offers several types of temperature loading:

The first method utilizes the EDLOAD,,TEMP command and the general loading procedure to apply a time-varying temperature to a specific nodal component. You must define two array parameters to represent the load; the first parameter contains the time values and the second parameter contains the temperature values. You may choose to define a load curve with these parameters or to input them directly on the EDLOAD command. You can also scale the temperature values using the SCALE parameter on EDLOAD. See General Loading Options for a complete description of how to apply this type of load.

The second method allows you to apply a uniform constant temperature to all nodes in the model. This method may be used to model a structure subjected to steady-state thermal loading. You can use the TUNIF command or the BFUNIF,TEMP command to apply this type of temperature load.

The third method allows you to apply the temperatures calculated in an ANSYS thermal analysis as loads in an explicit dynamic analysis. This method is useful for modeling temperature-dependent phenomena such as forging. To use this method, you must perform an implicit-to-explicit sequential solution. In the explicit phase, you use the LDREAD command to read the temperature data from the thermal (implicit) analysis results file (Jobname.RTH) and apply them as loads to the nodes in the model. You can only transfer the temperatures from one specified time point in the thermal analysis. Refer to Implicit-to-Explicit Sequential Solution of this guide for a detailed description of this loading procedure.

For all three methods of temperature loading, a reference temperature can be input via the TREF command. The thermal loading is defined as the difference between the applied temperature and the reference temperature. If the reference temperature is not specifically defined, it defaults to zero.

In order for any of these thermal loads to take effect, you must use the temperature dependent bilinear isotropic material model or the elastic viscoplastic thermal material model. The temperature dependent bilinear isotropic model can be used to represent a thermoelastic material (if needed) by omitting the yield strength and tangent modulus. Please refer to Material Models of this guide for complete descriptions of these material models.


Note:  It is important to note that the EDLOAD method of temperature loading cannot be used together with the LDREAD or TUNIF / BFUNIF methods of temperature loading. In addition, EDLOAD cannot be used to list or delete temperatures applied with LDREAD, TUNIF, or BFUNIF.


You can use LDREAD and TUNIF (or BFUNIF) together in the same explicit dynamic analysis. When LDREAD is issued, it applies temperature loads to the selected nodes, overwriting any temperature loads defined by TUNIF or BFUNIF. Any nodes that are unselected at the time LDREAD is issued will take on the temperature load defined by the TUNIF or BFUNIF command. To delete the temperature loads defined by LDREAD (at selected nodes or all nodes), use the BFDELE command. To list the temperature loads defined by LDREAD (at selected nodes or all nodes), use the BFLIST command.


Release 18.2 - © ANSYS, Inc. All rights reserved.