3.5. Adaptive Meshing

In metal forming and high-speed impact analyses, a body may experience very large amounts of plastic deformation. Single point integration explicit elements, which are usually robust for large deformations, may give inaccurate results in these situations due to inadequate element aspect ratios. To counteract this problem, the ANSYS LS-DYNA program has the ability to automatically remesh a surface during an analysis to improve its integrity. This capability, known as adaptive meshing, is controlled with the EDADAPT and EDCADAPT commands.

The EDADAPT command activates adaptive meshing within a specific PART ID. (Use the EDPART command to create and list valid PART IDs.) For example, to turn on adaptive meshing for PART ID #1, you would issue the following command:

EDADAPT,1,ON

Note:  Adaptive meshing is only valid for parts consisting of SHELL163 elements.


When adaptivity is turned on for a part, the mesh for that part will be automatically regenerated during an analysis to ensure adequate element aspect ratios are maintained throughout the deformation process. Adaptive meshing is most commonly used in the analysis of large deformation processes such as metal forming (adaptive meshing is typically used for the blank). To activate adaptive meshing for more than one part within a model, you must reissue the EDADAPT command for each different PART ID. By default, adaptive meshing is off for all parts within a model.

After specifying which parts will be adaptively meshed, you must also define adaptive meshing parameters using the EDCADAPT command. The EDCADAPT command globally sets the control options for all PART IDs that are to be adaptively meshed as defined by the EDADAPT command. The parameters controlled by the EDCADAPT command are listed below.

For most problems, you should do an initial analysis without adaptive meshing. If the results of the initial analysis show a highly distorted mesh and if the solution appears to be incorrect, then you can rerun the analysis with adaptive meshing turned on. Adaptive meshing may also be used when an analysis terminates in LS-DYNA with a “negative volume element” error.

When adaptive meshing is turned on, the number of elements within the model will change during the solution. After each adaptive loop, the mesh will be updated and a new results file will be written with the extension RSnn, where nn is the adaptive mesh level. (An adaptive loop will occur at every time increment specified by FREQ or at the time intervals specified by LCID.) For example, a model that is adaptively remeshed two times will produce two results files, Jobname.RS01 and Jobname.RS02. For details on postprocessing adaptively meshed results, see Postprocessing after Adaptive Meshing.


Note:  A new results file will be created for each loop, even if the mesh does not change.


A new time history file having the extension HInn is also written each loop; however, these files may not be as useful for postprocessing as the RSnn files. In addition, LS-DYNA creates a set of adaptive meshing files with the root name "adapt". Therefore, you should not use "adapt" as your jobname when adaptive meshing is activated.


Release 18.2 - © ANSYS, Inc. All rights reserved.