In metal forming and high-speed impact analyses, a body may experience very large amounts of plastic deformation. Single point integration explicit elements, which are usually robust for large deformations, may give inaccurate results in these situations due to inadequate element aspect ratios. To counteract this problem, the ANSYS LS-DYNA program has the ability to automatically remesh a surface during an analysis to improve its integrity. This capability, known as adaptive meshing, is controlled with the EDADAPT and EDCADAPT commands.
The EDADAPT command activates adaptive meshing within a specific PART ID. (Use the EDPART command to create and list valid PART IDs.) For example, to turn on adaptive meshing for PART ID #1, you would issue the following command:
EDADAPT,1,ON
When adaptivity is turned on for a part, the mesh for that part will be automatically regenerated during an analysis to ensure adequate element aspect ratios are maintained throughout the deformation process. Adaptive meshing is most commonly used in the analysis of large deformation processes such as metal forming (adaptive meshing is typically used for the blank). To activate adaptive meshing for more than one part within a model, you must reissue the EDADAPT command for each different PART ID. By default, adaptive meshing is off for all parts within a model.
After specifying which parts will be adaptively meshed, you must also define adaptive meshing parameters using the EDCADAPT command. The EDCADAPT command globally sets the control options for all PART IDs that are to be adaptively meshed as defined by the EDADAPT command. The parameters controlled by the EDCADAPT command are listed below.
Frequency (FREQ) - The time interval between which
adaptive mesh refinements will take place. For example, if
FREQ is set to 0.01, elements will be adaptively
remeshed every .01 seconds (assuming the time unit used is seconds) if they are
above the specified angle tolerance. Since the default value for the
FREQ field is 0.0, this field must be specified
when using adaptive meshing in an analysis.
Angle Tolerance (TOL) - The adaptive angle
tolerance (in degrees) for which adaptive meshing will occur (default = 1e31).
The TOL field controls the aspect ratio between
elements and is very important for ensuring accurate results. If the relative
angle between elements exceeds the specified TOL
value, the elements will be automatically refined.
Adaptivity Option (OPT) - There are two different
angle options available for mesh adaptivity. For OPT
= 1, the angle change that is compared to the specified
TOL value is computed based on the original mesh
configuration. For OPT = 2, the angle change that is
compared to the specified TOL value is computed based
on the previously refined mesh.
Mesh Refinement Levels (MAXLVL) - The
MAXLVL field controls the number of times an
element can be remeshed during the entire analysis. For a single original
element, a MAXLVL of 1 would allow the creation of
one additional element, a MAXLVL of 2 would allow the
creation of up to four additional elements, and a
MAXLVL of 3 would allow the creation of up to 16
additional elements. High values of MAXLVL will yield
more accurate results, but can dramatically increase the model size.
Remeshing Birth and Death Times (BTIME and
DTIME) - The remeshing birth and death times
control when adaptive meshing is turned on and off in an analysis. For example,
if you set BTIME = .01 and
DTIME = .1, adaptive meshing will only take place
in the analysis between .01 and .1 seconds (assuming the time unit used is
seconds).
Interval of Remeshing Curve (LCID) - This data
curve (specified on the EDCURVE command) defines the interval
of remeshing as a function of time. The abscissa of the data curve is time, and
the ordinate is the varied adaptive time interval. If this option is nonzero,
the adaptive frequency (FREQ) will be replaced by
this data curve. Note, however, that a nonzero FREQ
value is still required to initiate the first adaptive loop.
Minimum Element Size (ADPSIZE) - Minimum element
size to be adapted based on element edge length. If this parameter is undefined,
the edge length limit is ignored.
One or Two Pass Option (ADPASS) - If
ADPASS = 0, two pass adaptivity is used, and the
calculation is repeated after adaptive remeshing (this is the default). If
ADPASS = 1, one pass adaptivity is used, and the
calculation is not repeated after adaptive remeshing. See Figures 30.9(a) and
30.9(b) in the LS-DYNA Theoretical Manual for graphical
representations of these two options.
Uniform Refinement Level Flag (IREFLG) - Values of
1, 2, 3, etc. allow 4, 16, 64, etc. elements, respectively, to be created
uniformly for each original element.
Penetration Flag (ADPENE) - Depending on whether
the value of ADPENE is positive (approach) or
negative (penetrate), the program will adapt the mesh when the contact surfaces
approach or penetrate the tooling surface by this value. The tooling adaptive
refinement is based on the curvature of the tooling. If
ADPENE is positive, the refinement generally
occurs before contact takes place; consequently, it is possible to use one pass
adaptivity (ADPASS = 1).
Shell Thickness Level (ADPTH) - Absolute shell
thickness level below which adaptivity should begin. This option works only if
the adaptive angle tolerance (TOL) is nonzero. If
thickness based adaptive remeshing is desired without angle change, set
TOL to a large angle. (If
ADPTH = 0.0, this option is not used.)
Maximum Element Limit (MAXEL) - Maximum number of
elements at which adaptivity will be terminated. Adaptivity is stopped if this
number of elements is exceeded.
For most problems, you should do an initial analysis without adaptive meshing. If the results of the initial analysis show a highly distorted mesh and if the solution appears to be incorrect, then you can rerun the analysis with adaptive meshing turned on. Adaptive meshing may also be used when an analysis terminates in LS-DYNA with a “negative volume element” error.
When adaptive meshing is turned on, the number of elements within the model will
change during the solution. After each adaptive loop, the mesh will be updated and a new
results file will be written with the extension RSnn,
where nn is the adaptive mesh level. (An adaptive
loop will occur at every time increment specified by FREQ or
at the time intervals specified by LCID.) For example, a
model that is adaptively remeshed two times will produce two results files,
Jobname.RS01 and Jobname.RS02. For details
on postprocessing adaptively meshed results, see Postprocessing after Adaptive Meshing.
Note: A new results file will be created for each loop, even if the mesh does not change.
A new time history file having the extension HInn is also written each loop; however, these files may not be as useful for postprocessing as the RSnn files. In addition, LS-DYNA creates a set of adaptive meshing files with the root name "adapt". Therefore, you should not use "adapt" as your jobname when adaptive meshing is activated.