8.4. Switching Parts from Deformable to Rigid

In some dynamic applications, long duration, large rigid body motions arise that are prohibitively expensive to simulate if the majority of elements in the model are deformable. One such example would be an automotive rollover where the time duration of the rollover would dominate the CPU cost relative to the impact that occurs much later. To improve efficiency for this class of applications, ANSYS LS-DYNA offers the capability to switch a subset of materials from a deformable state to a rigid state, and then back to deformable. By switching the deformable parts to rigid during the rigid body motion stage, you can achieve significant savings in computation time.

Deformable/rigid switching is inherently related to performing a restart. You need to stop the analysis, define the part switch, then restart the analysis again. Although you would not typically use part switching in the original analysis, you must set a flag in the new analysis input to let LS-DYNA know that all materials in the model have the potential to become rigid bodies sometime during the calculation. Issuing the EDRD or EDRI command in the original analysis will set this flag.


Note:  Parts that are defined as rigid using the command EDMP,RIGID are permanently rigid and cannot be changed to deformable.


To switch a deformable part to a rigid part, issue

EDRD,D2R,PART,MRB

where PART is the part number, and MRB indicates a master rigid part to which the switched part should be merged. (In the GUI, go to Main Menu> Solution> Rigid-Deformable> Switch.) If you do not wish to merge the part to another rigid body, simply leave MRB blank. Once a deformable part is switched to rigid using the above command, you can switch it back to deformable in a subsequent restart by issuing

EDRD,R2D,PART

In a new analysis, if no deformable materials are going to be switched to rigid but switching may occur in a subsequent restart analysis, then issue EDRD,D2R with no additional arguments. (In the GUI, go to Main Menu> Solution> Rigid-Deformable> Switch and select “Initialize” as the action.)

When you switch a deformable part to rigid, you can define the inertia properties for the rigid part by issuing the EDRI command (Main Menu> Solution> Rigid-Deformable> Inertia Property). If you do not define the inertia properties, they will be calculated by the program.

After a deformable-to-rigid switch, some constraints defined for the deformable part will become invalid. To avoid instabilities in the calculations, you should use the EDRC command (Main Menu> Solution> Rigid-Deformable> Controls) to change the state of these constraint definitions. Please refer to the EDRC command description for more details.

For rigid body switching to work properly, the choice of element formulation is critical. In the current LS-DYNA implementation, Hughes-Liu shell and beam elements cannot be used with part switching because of the strain and stress update algorithms used in these elements. The element formulations that cannot be used include KEYOPT(1) = 1, 6, 7, and 11 for SHELL163 and KEYOPT(1) = 0 and 1 for BEAM161.

A special consideration for SOLID164 elements is that, upon switching from a rigid state to deformable, the element stresses are zeroed out to eliminate spurious behavior.


Release 18.2 - © ANSYS, Inc. All rights reserved.