This section discusses advanced features of the Drop Test Module that are provided as a convenience, but may not be required in a typical drop test analysis. These features include options to specify initial translational and angular velocities, modify the target's position and properties, and specify contact surface friction coefficients. Details on these features are included in the following sections.
By default, the translational and angular velocities of the object being dropped are assumed to be zero at the time of the drop. You can impose an initial translational and/or angular velocity on the object being dropped; however, in certain cases when you specify initial angular velocities, as discussed below, the “near impact time” starting option is not valid and the GUI prevents you from making this choice. The “near impact time” starting option is further discussed in Basic Tab of the Drop Test Set-up Dialog Box , under Solution Time in this user's guide.
You should always input initial velocities corresponding to the time of the "drop", even if the analysis is set to begin near impact. The program will calculate the initial translational velocity at the start of the analysis based on the initial velocity input and the acceleration due to gravity.
The initial velocities that you specify are applied via the EDVEL command. This command is discussed further under Initial Velocity in this user's guide.
You can specify initial translational or angular velocity by choosing then choosing the Velocity tab. Under either the Translational Velocity or Angular Velocity headings, you can choose to input the velocity in terms of screen coordinates or object coordinates. After choosing the desired option, simply input the X, Y, and Z components of the velocity. If you enter the velocity relative to the screen coordinates, the components are resolved into the object coordinates internally by the DTM before being input on the EDVEL command. See Velocity Tab of the Drop Test Set-up Dialog Box in this user's guide for more information.
The target is one rigid SOLID164 brick element, which is created automatically in the Drop Test Module and is always assumed to be stationary. Figure 17.1: Two Views of the Target(a) shows the target in the default drop test viewing orientation, and Figure 17.1: Two Views of the Target(b) is an alternate view of the target that more clearly shows its geometry. Figure 17.1: Two Views of the Target(b) shows that the target has two faces that are much larger than the other four. The two large faces lie in planes that are parallel to each other. The large face that has an outward normal vector directed along the screen Y axis (by default) is the “top” face of the target.
It is expected that the default target position, size, orientation, material properties, and contact parameters will be acceptable for most analyses. But if necessary, you can change the characteristics of the target by following the procedures outlined in the following sections.
You can change the target position by redefining the reference for the target center.
To change the target position, choose then choose the Target tab. Under the Dimensions heading, there are two options from which you can choose for centering the target in the screen X-Z plane. You can align the target's center of gravity either underneath the object's center of gravity, or underneath the object's lowest Y coordinate point. See Target Tab of the Drop Test Set-up Dialog Box in this user's guide for more information.
The default target size is based on the characteristic target length TL. The program calculates TL based on the overall dimensions of the object being dropped. By default, the sides of the two large square faces of the target are of length 2TL, and the thickness of the target in the direction normal to these two faces is 0.1TL.
You can change the size of the target by choosing then choosing the Target tab. Under the Dimensions heading, you can enter two target scaling factors, one for scaling the target length (Ls) and one for scaling the target thickness (Ts). Thus, the sides of the two large square faces are of length 2LsTL, and the target height is 0.1TsTL. As an example, If you input Ls=2.0 and Ts=0.5, then the target is recreated with sides that are twice the default length and a thickness that is half its default value. Using this option to change the target size does not alter the location of the target center point. If you change the target's size, the target is re-drawn automatically. See Target Tab of the Drop Test Set-up Dialog Box in this user's guide for more information.
By default, the target is oriented so that its two large faces are normal to the screen Y axis, and therefore normal to (g). But you may need to change the target orientation for your particular model. For example, you may want to simulate the object being dropped onto an inclined plane. To modify the target orientation, choose , choose the Target tab. Under the Orientation angle heading, you type an angle in degrees that is used to rotate the target about the screen Z axis (which is normal to the screen and toward the viewer) using a right-hand rule. This is ideal for creating an inclined plane target. If the target is not in its default orientation when this option is chosen, it is initially returned to its default orientation so that it is always modified beginning from the default. If you change the target's orientation, the target is re-drawn automatically. See Target Tab of the Drop Test Set-up Dialog Box in this user's guide for more information.
Although the target is always defined to be rigid, a material density, modulus of elasticity, and Poisson's ratio are still required for the LS-DYNA solution. Material properties are used for a contact stiffness calculation and a time step calculation. Details on the contact stiffness and time step can be found under Contact Surfaces in this user's guide.
By default, the target is defined to be rigid using the EDMP command:
EDMP,RIGID,MAT,7,7The material number (MAT) used is one greater than
the highest material number used by the model of the object being dropped. The
default property values used for the target depend on the material properties
used for the object. The Drop Test Module searches through all materials
belonging to the object, finds the one with the lowest elastic modulus, and
stores the corresponding material number. The modulus, density, and
Poisson’s ratio corresponding to this material number are also specified
as the modulus, density, and Poisson’s ratio of the target material.
If you know the actual target material properties, it is preferred that you input them directly. To specify the properties, choose , choose the Target tab, then, under the Material Properties heading, enter the Young's modulus, density, and Poisson's ratio. See Target Tab of the Drop Test Set-up Dialog Box in this user's guide for more information.
In the Drop Test Module, automatic single surface contact (AG) is defined for the entire model. The contact is specified via the EDCGEN command.
You can change the static friction coefficient
(FS), the dynamic friction coefficient
(FD), and the exponential decay coefficient
(DC). These coefficients apply to all contact
surfaces, including the target surface. You can input values for these
coefficients by choosing ,
then choosing the Target tab.
If you do not change parameters FS,
FD, or DC, then they
have default values of 0.0. See Target Tab of the Drop Test Set-up Dialog Box in this user's guide for
more information.