The step-by-step procedure described in this section can be used as a guide for most types of drop test analyses. A typical test would involve dropping an object from some height in a gravitational field onto a flat, rigid surface (target), neglecting surface friction. The basic procedure outlined here assumes that the object has a zero initial velocity, and the object is being dropped onto a target that lies in a plane which is normal to the direction of the acceleration due to gravity. More advanced features, such as inclusion of surface friction effects, specification of a nonzero initial velocity (translational and/or angular), and modification of the target size, properties, and orientation, are discussed in Advanced DTM Features in this user's guide.
Before you begin, it is important for you to understand how the screen coordinates are used within the Drop Test Module. In the DTM, the screen coordinates are always defined so that the screen Y axis (vertical) is in the direction opposite to the acceleration due to gravity (g). Thus, screen coordinates are used as a convenient method for keeping track of the relationship between the object to be dropped and the gravitational field. See Screen Coordinates Definition in this user's guide for more details.
Before entering the Drop Test Module, you must build or import the model of the object to be dropped. All elements should be defined and all material properties, including damping, should be specified. Only elements that are compatible with LS-DYNA (that is, explicit dynamic elements) should be included in the model. Make sure that there are not materials defined with either density or modulus of elasticity equal to zero. Otherwise, you will not be able to set up the DTM. See Elements in this user's guide for more information.
To avoid time increment degeneration problems, follow these guidelines when building the model:
Avoid triangular, tetrahedron, and prism elements
Avoid small elements
Avoid acute-angled elements
Use as uniform a mesh as possible
We recommend that a certain degree of damping be applied to the model to reduce the oscillatory response. You can apply both alpha (mass weighted) and beta (stiffness weighted) damping using the EDDAMP command.
Note: After completing the model and before entering the DTM, it is good practice to save the existing database under a unique name (pick ).
You set up your analysis in the DTM by choosing . The Drop Test Set-up dialog box appears that includes several tabbed pages. The most common drop test analysis parameters are on the Basic tab, while parameters you may occasionally need to modify are included on most of the remaining tabs. A description of each tab is presented below along with the tasks you can perform within the tab:
Basic tab -- Specify magnitude of acceleration due to gravity (g), object drop height, object orientation, analysis start time, run time after impact, and the number of times data is written to the results file and to the time history output file. See Basic Tab of the Drop Test Set-up Dialog Box in this user's guide for more information.
Velocity tab -- Modify initial translational and/or angular velocity of the object. See Velocity Tab of the Drop Test Set-up Dialog Box in this user's guide for more information.
Target tab -- Modify dimensions and material properties of the target, rotate the target, and define contact and friction properties for the target. See Target Tab of the Drop Test Set-up Dialog Box in this user's guide for more information.
Status tab -- Display the values currently set for acceleration due to gravity, initial translational and angular velocity, and the estimated time at the end of solution. See Status Tab of the Drop Test Set-up Dialog Box in this user's guide for more information.
While the Drop Test Set-up dialog box is displayed, no other ANSYS menus are available until you choose or .
The remainder of this section (STEP 3 through STEP 9) discusses the options you would use during a typical drop test analysis. Advanced options that are not commonly used are covered in Advanced DTM Features in this user's guide.
You must specify the magnitude of (g) by choosing the Basic tab. Under the Gravity heading, you pick a (g) value corresponding to the test specific system of units (386.4, 32.2, etc.), or you can type your own value.
You must specify the drop height on the Basic tab. Under the Drop Height heading, you type the drop height, and specify a reference point. The drop height is measured along the screen Y axis from the center of the top face of the target to some height reference point within the model. Reference point options include the lowest object point, that is, the point on the object with the minimum screen Y coordinate value, or the object's center of gravity as calculated by ANSYS. The drop height that you input must be in length units that are consistent with the rest of the analysis (gravity for example).
In the DTM, the screen coordinates are automatically defined with the Y axis directed opposite to the direction of (g). You can orient the object with respect to the gravitational field under the Set Orientation heading on the Basic tab. There you have the option of orienting the object by using the DTM Rotate tool, or by picking nodes on the object that define a vector parallel to the screen Y direction.
You can access solution control options on the Basic tab.
Under the Solution time heading, you can specify when the
analysis starts (near impact time or at drop time), as well as the run duration
time after impact. Under the Number of Results Output
heading, you can specify the number of times results are written to the results
file (file.RST) and to the
time-history file
(file.HIS).
For more information on the tasks involved in STEP 3 through STEP 6, see Basic Tab of the Drop Test Set-up Dialog Box in this user's guide.
Before solving, you should make sure that you are satisfied with the information in the Drop Test Set-up dialog box. Perform any of the following verification steps:
Review the information under all of the tabs.
Click on the Status tab since this displays your most updated input data.
View the object and the target in the ANSYS Graphics window.
If you choose the Status tab, ANSYS attempts to automatically create the target (unless you have already created it by choosing the Target tab) and displays a statement in black print at the end of the Status tab page indicating that all the set-up data is acceptable and you can proceed to solve the analysis, or a statement in yellow print indicating that you should proceed with caution because the data produced error messages, or a statement displayed in red indicating that the set-up data is unacceptable.
If you receive either the second or third statement regarding error messages, check them in the ANSYS Output window. See Status Tab of the Drop Test Set-up Dialog Box in this user's guide for more information on using the Status tab. Make changes if necessary, then choose . At this time, all of the standard ANSYS menus become usable again. You then initiate the LS-DYNA solution by choosing .
Note: A database that you save from the current version of ANSYS LS-DYNA DTM is not compatible with a previous version of ANSYS LS-DYNA DTM.
Once the solution is completed, you can choose to animate dynamic results (such as von Mises stresses) for the dropped object over the analysis time duration. For animating results, it is recommended that you choose to start the analysis at drop time. See Postprocessing - Animation in this user's guide for information on the Animate Over Results dialog box, and see Animation in the Basic Analysis Guide for general information on producing animations in ANSYS.
In addition to animating the results, you can also review the analysis results at specific points in the model as a function of time by choosing . See Postprocessing and Postprocessing - Graph and List Time-History Variables in this user's guide for more information.
When you first enter the DTM, screen Cartesian coordinates, which are fixed, are defined automatically, and are represented graphically in the lower left corner of the ANSYS Graphics window. Screen coordinates are used as a convenient way of keeping track of the relationship between the object to be dropped and the gravitational field. There are three important points you should understand about screen coordinates:
In the DTM, screen coordinates are always defined so that the screen Y axis is in the direction opposite to the acceleration due to gravity, (g).
Screen coordinates are defined with respect to global Cartesian coordinates.
Object coordinates can be rotated with respect to the screen coordinates.
The screen coordinates are always defined so that the Y axis is in the screen “up” direction. The object coordinate system is the coordinate system in which the finite element model was defined. You can reorient the object coordinate system using the DTM Rotate tool. You can define a vector to be parallel to the screen Y coordinate system by picking two nodes on the object. See Basic Tab of the Drop Test Set-up Dialog Box in this user's guide for more information. By redefining the object Y direction, you are specifying the relationship between the object and the gravitational field, because the screen Y direction is always assumed to be “up” or opposite to the direction of the acceleration due to gravity, (g).
The screen coordinates also determine the default drop test viewing orientation, which is defined as follows:
The screen X direction is "right" (to the viewer's right).
The screen Y direction is "up" on the screen.
The screen Z axis is along the normal from the screen to the viewer, or "out".
This section contains some notes of interest and practices to follow that will help you to use the DTM more effectively. Some of these points were mentioned briefly in previous sections.
During initialization, a keyword is created that is related to the filtering of menu picks in the DTM. The keyword is DTFILT. You should avoid using this word as a keyword or a parameter name, as it could interfere with the filtering of menu options.
Within the DTM, a component containing all the nodes in the object is automatically created and given the name _dtdrpob. This component name is used in issuing commands associated with LS-DYNA. You should avoid using this name.
Parameters _dtcgnum and _dtlownum are used for time-history postprocessing plots and lists. You should avoid using these names.
The DTM assumes that there are no constraints imposed on the object being dropped. However, coupling of components within an object is allowed.
Some parameter names used internally by the Drop Test Module begin with the underscore character (_), so you should avoid using parameter names that begin with an underscore. (This is true for any ANSYS analysis.)
If you do not choose to orient the object, the default assumption is the current screen Y axis view, which is directed opposite to the acceleration due to gravity (g).
You can modify any input set up parameter any number of times before entering the solution phase. All parameters in the Drop Test Module are subject to redefinition after being initially defined. You will see that whenever an input parameter that affects the initial target/object orientation is changed, the target is recreated automatically to reflect the change when you click on the Target tab or the Status tab.
After you specify a drop height, you will notice that, by default, the target is located nearly in contact with the object. This is due to the default option to begin the analysis near impact time. The target is created with just a small separation between the object and target. You may want to adjust the Solution time option to begin the analysis “at drop time”. After doing so, you will observe that the redefined target is at a position consistent with the specified drop height. However, while this option provides full animation of the drop scenario, it will require more computation time.
To use the option to start the analysis near impact time, the initial angular velocity must be zero.
The Drop Test Module does not alter the model of the object in any way. The DTM does create a model of a target after you specify a new orientation for the object.