In a transient analysis, the rotating forces are defined using table array parameters to specify the amplitude of the forces in each direction, at each time step. The analysis example provided in Example: Transient Response of a Startup shows how this is accomplished.
Because complex notations are used in a harmonic analysis, a rotating load is defined with both a real component and an imaginary component (as described in Harmonic Analysis for Unbalance or General Rotating Asynchronous Forces in the Advanced Analysis Guide). For example, to apply a rotating force F0 in the (YZ) plane, rotating in the counterclockwise direction (Y to Z), the force components are:
F0 = 1.e+6 ! sample force component value INODE = node(0.1,0,0) ! sample node number F,INODE,fy, F0 ! real fy component at node INODE F,INODE,fz,, -F0 ! imaginary fz component at node INODE
For more information, see Applying Loads and Obtaining the Solution in the Structural Analysis Guide.
If the rotating harmonic load is synchronous or asynchronous with the rotational velocity, use the SYNCHRO command. In this case, the amplitude of the force generated by unbalance represents the mass times the radius of the eccentric mass. The spin squared factor is introduced automatically. See Example: Unbalance Harmonic Response of a Two-Spool Rotor for more information about harmonic analysis with rotating forces.
If a solid or shell model is not exactly axisymmetric, it induces unbalance forces that may need to be taken into account in your harmonic analysis. To determine and apply such forces, do the following:
Create nodes on the rotational velocity axis (center line) of the rotor model.
Couple the model to the center nodes that define a rigid region (CERIG command).
If the rotational velocity is along X, constrain UY, UZ, and ROTX degrees of freedom at the center nodes. Do not constrain the bearings locations.
Perform a static analysis with unit rotational velocity
(OMEGX=1.0 on the
OMEGA command).
In the post-processor (/POST1), retrieve and store the reaction forces
at the center nodes (Entity=Node and
Item1=RF on the *GET
command).
You can perform your harmonic analysis after you have:
Removed the constraints at the center nodes.
Added your constraints at the bearings locations.
Applied the stored reaction forces at the center nodes. Ensure that you take the opposite sign and define complex rotating forces.