6.7. Performing a DDAM Spectrum Analysis

The general process for performing a DDAM spectrum analysis consists of four primary steps:

If you wish to perform mode selection that includes and expands only the significant modes in a DDAM spectrum analysis, refer to Mode Selection Based on the DDAM Procedure.

The first two steps for a DDAM analysis are the same steps described for a modal analysis (see Step 1: Build the Model and Step 2: Obtain the Modal Solution). The procedure for the remaining steps is explained below:

6.7.1. Step 3: Obtain the Spectrum Solution

In this step, the program uses mode shapes extracted by the modal solution to calculate the DDAM solution. The following requirements apply:

  • The mode shape file (Jobname.MODE) must be available.

  • The database must contain the same model from which the modal solution was obtained.

  • The Jobname.ESAV file must be available.

  • The Jobname.FULL file must be available for the participation factors calculation.


Note:  If the DDAM analysis is not performed in the same directory as the modal analysis, remote modal files usage must be activated (MODDIR). In this case, the DDAM information is stored in the Jobname.PRS file and the modal analysis files in the modal analysis directory are not modified.


  1. Enter SOLUTION.

    Command(s): /SOLU
    GUI: Main Menu> Solution
  2. Define the analysis type and analysis options. Mechanical APDL offers the following analysis options for a spectrum analysis. Not all modal analysis options and eigenvalue extraction techniques work with all spectrum analysis options.

    Table 6.5:  Analysis Types and Options

    OptionCommandGUI Path
    New Analysis ANTYPE Main Menu> Solution> Analysis Type> New Analysis
    Analysis Type: Spectrum ANTYPE Main Menu> Solution> Analysis Type> New Analysis> Spectrum
    Spectrum Type: DDAM SPOPT Main Menu> Solution> Analysis Type> Analysis Options
    Number of Modes to Use for Solution SPOPT Main Menu> Solution> Analysis Type> Analysis Options

    • Option: New Analysis [ANTYPE]

      Select New Analysis.

    • Option: Analysis Type: Spectrum [ANTYPE]

      Select analysis type spectrum.

    • Option: Spectrum Type: Single-point Response Spectrum [SPOPT]

      Select Dynamic Design Analysis Method (DDAM).

    • Option: Number of Modes to Use for Solution [SPOPT]

      Select a sufficient number of modes to characterize the structure's response and cover the frequency range spanned by the spectrum. The accuracy of the solution depends on the number of modes used. The larger the number of modes used, the higher the accuracy will be.

  3. Specify load step options.

    • The global excitation direction is specified using the SED command. Only excitation specified using SED is supported in a DDAM analysis.

    • Use the ADDAM and VDDAM commands to specify the spectrum values and types. Based on the coefficients specified in the ADDAM and VDDAM commands, the program calculates the mode coefficients according to the empirical equations given in Dynamic Design Analysis Method in the Mechanical APDL Theory Reference.

    • You can also specify the spectrum values using the DDASPEC command. Based on the ship type, mounting location, deformation type, and minimum acceleration value, spectrum coefficients are calculated based on NRL-1396. These coefficients are then used to calculate the mode coefficients according to the empirical equations given in Dynamic Design Analysis Method in the Mechanical APDL Theory Reference.

    • No damping needs to be specified for solution because it is implied by the ADDAM and VDDAM commands. If damping is specified, it is used for mode combinations, but ignored for solution.

    • Use the /UNITS command before defining the shock spectrum to perform the DDAM spectrum analysis in a units system other than BIN (default). Valid unit systems are SI, MKS, μMKS, CGS, MPA, BFT, and BIN.

    • Spectrum Options:

      The following options are included:

      • Residual Vector [RESVEC]

        The residual vectors reduce the error caused when higher modes are neglected in the analysis.

        Missing Mass and Rigid Response are not supported in a DDAM analysis.

  4. Combine the modes. A maximum of 10,000 modes can be combined.

    Select one of the following mode combination methods offered for the single-point response spectrum analysis:

    • Square Root of Sum of Squares (SRSS)

    • Complete Quadratic Combination (CQC)

    • Double Sum (DSUM)

    • Grouping (GRP)

    • Naval Research Laboratory Sum (NRLSUM)

    • Rosenblueth (ROSE)

    The NRLSUM method is typically used in the context of the Dynamic Design and Analysis Method (DDAM) spectrum analysis.

    The Closely Spaced Modes (CSM) Method is also available using the NRLSUM,,,CSM command. It uses the NRL summation to process any out-of-phase modal responses with closed form treatment (NAVSEA  [412]).

    The following commands are used to invoke different methods of mode combinations:

    Command(s): SRSS, CQC, DSUM, GRP, NRLSUM, ROSE
    GUI: Main Menu> Solution> Analysis Type> New Analysis> Spectrum
    Main Menu> Solution> Analysis Type> Analysis Opts> D.D.A.M
    Main Menu> Load Step Opts> Spectrum> Mode Combine 

    These commands allow computation of three different types of responses:

    • Displacement (Label = DISP)

      Displacement response refers to displacements, stresses, forces, etc.

    • Velocity (Label = VELO)

      Velocity response refers to velocities, stress velocities, force velocities, etc.

    • Acceleration (Label = ACEL)

      Acceleration response refers to accelerations, stress accelerations, force accelerations, etc.

    These commands can also be used to specify the type of modal forces used in the combination. ForceType = STATIC (default) combines the modal static forces (i.e., stiffness multiplied by mode shape forces, both of which are stress-causing forces). ForceType = TOTAL combines the summed modal static forces and inertia forces (i.e., stiffness and mass forces, both of which forces are seen by the supports).

    The DSUM method also accommodates time-duration input for earthquake or shock spectrum.

    The mode combination phase writes a file of POST1 commands (Jobname.MCOM). Read in Jobname.MCOM in POST1 to do the mode combinations using the results file (Jobname.RST) from the modal expansion pass.

    The file Jobname.MCOM contains POST1 commands that combine the maximum modal responses by using the specified mode combination method to calculate the overall response of the structure.

    The mode combination method determines how the structure's modal responses are to be combined:

    • If displacement  is selected as the response type (Label = DISP), displacements and stresses are combined for each mode on the mode combination command.

    • If velocity is selected as the response type (Label = VELO), velocities and stress velocities are combined for each mode on the mode combination command.

    • If acceleration is selected as the response type (Label = ACEL), accelerations and stress accelerations are combined for each mode on the mode combination command.


    Note:  A DDAM spectrum analysis may alternately be performed in two separate solves: first, the spectrum solution, and then the mode combination. The damping needed by the mode combination must be specified before the spectrum solve.


  5. Start solution.

    Command(s): SOLVE
    GUI: Main Menu> Solution> Solve> Current LS

    The output from the solution includes the Response Spectrum Calculation Summary. This table, which is part of the printed output, lists the participation factors, mode coefficients (based on lowest damping ratio), and the weight distribution for each mode. To obtain the response of each mode (modal response), multiply the mode shape by the mode coefficient (based on lowest damping ratio). You do this by retrieving the mode coefficient with the *GET command (Entity = MODE) and using it as a scale factor in the SET command.

    If needed, you can retrieve the frequencies, participation factors, mode coefficients and effective damping ratios with the *GET command (Entity = MODE).

    In addition to the above, the output from the solution also includes a DDAM Response Spectrum Calculation Summary. This table, which is part of the printed output, lists the shock design value and spectrum loading type for each mode.

    You can use the *GET command (Entity = DDAM) to retrieve the shock design values from the last DDAM spectrum solve.

  6. Repeat Step 3 to excite the structure along different directions if necessary. Note that solutions are not written to the Jobname.RST file at this time.

  7. Leave the SOLUTION processor.

    Command(s): FINISH
    GUI: Close the Solution menu.

    Note:  To calculate the effect of multiple spectra independently, see Running Multiple Spectrum Analyses.


6.7.2. Step 4: Review the Results

Results from a DDAM analysis are written to the mode combination file Jobname.MCOM in the form of POST1 commands. These commands calculate the overall response of the structure by combining the maximum modal responses in some fashion (specified by one of the mode combination methods). The overall response consists of the overall displacements (or velocities or accelerations). If element result calculations were requested in the expansion pass and stored in the results file, the overall response also includes the overall stresses (or stress velocities or stress accelerations), strains (or strain velocities or strain accelerations), and reaction forces (or reaction force velocities or reaction force accelerations).

You can use POST1, the general postprocessor, to review the results. See Step 4: Review the Results for details about the post-processing.

6.7.3. Example: DDAM Spectrum Analysis

!  Build the Model
/FILNAM,                        ! Jobname
/TITLE,                         ! Title
/PREP7                          ! Enter PREP7
 ...
 ...                            ! Generate model
 ...
FINISH
!
!  Obtain the Modal Solution
/SOLU                           ! Enter SOLUTION
ANTYPE, MODAL                   ! Modal analysis
MODOPT, LANB                    ! Block Lanczos method
MXPAND, ...                     ! Number of modes to expand, ...
D, ...                          ! Constraints
SOLVE                           ! Initiates solution
SAVE
FINISH
!
!  Obtain the Spectrum Solution
/SOLU                           ! Reenter SOLUTION
ANTYPE, SPECTR                  ! Spectrum analysis
SPOPT, DDAM, ...                ! Dynamic design analysis method  
                              
ADDAM, ...                      ! Acceleration spectrum computation constants
VDDAM, ...                      ! Velocity spectrum computation constants 

DMPRAT, ...                     ! Specify damping ratio required if CSM method is used
SED, ...                        ! Specify excitation direction of shock spectrum
NRLS,,, CSM,                    ! NRLSUM mode combinations with Closely Spaced Modes Method (CSM)
                                
SOLVE                           ! Initiates solution
FINISH
!

!  Review the Results
/POST1                          ! Enter the database results postprocessor
/INPUT,,MCOM                    ! Read mode combination file
...! Postprocess as desired 
...! (PRNSOL; PRRSOL; PRDI; PRNSOL; etc.)
...
FINISH

Release 18.2 - © ANSYS, Inc. All rights reserved.