A nonlinear transient analysis is performed in three load steps using structural-thermal options of SOLID226 and CONTA174.
FSW simulation includes factors such as nonlinearity, contact, friction, large plastic deformation, structural-thermal coupling, and different loadings at each load step. The solution settings applied consider all of these factors.
The first load step in the solution process converges within a few substeps, but the second and third load steps converge only after applying the proper solution settings shown in the following table:
Table 28.4: Solution Settings
| Solution Setting | Description of Setting and Comments |
|---|---|
| ANTYPE,4 | Transient analysis. |
| LNSRCH,ON | For contact problems, this option is useful for enhancing convergence. |
| CUTCONTROL, PLSLIMIT,0.15 | Controls the time-step cutback during a nonlinear solution and specifies the maximum equivalent plastic strain allowed within a time-step. If the calculated value exceeds the specified value, the program performs a cutback (bisection). PLSLIMIT is set at 15 percent (from the default five percent) because solution-control support is not available. |
| NLGEOM,ON | Includes large-deflection effects or large strain effects, according to the element type. |
| NROPT,UNSYM | Recommended for contact elements with high friction coefficients. |
| TIMINT,OFF,STRUC | To speed up convergence in a coupled-field transient analysis, the structural dynamic effects are turned off. These structural effects are not important in the modeling of heat generation due to friction; however, the thermal dynamic effects are considered here. |
| KBC,0 | The loads applied to intermediate substeps within the load step are ramped because the structural dynamic effects are set to off. |
To allow for a faster solution, automatic time-stepping is activated (AUTOTS,ON). The initial time step size (DELTIM) is set to 0.1, and the minimum time step is set to 0.001. The maximum time step is set as 0.2 in load steps 2 and 3. A higher maximum time-step size may result in an unconverged solution.
The time step values are determined based on mesh or element size. For stability, no time-step limitation exists for the implicit integration algorithm. Because this problem is inherently nonlinear and an accurate solution is necessary, a disturbance must not propagate to more than one element in a time step; therefore, an upper limit on the time step size is required. It is important to choose a time step size that does not violate the subsequent criterion (minimum element size, maximum thermal conductivity over the whole model, minimum density, and minimum specific heat).
The following example input defines the solution settings:
/solu
lnsrch,on ! Activating a line search to be used with
! Newton-Raphson (for contact problem)
cutcontrol,plslimit,0.15 ! Controls time-step cutback during a
! solution,Maximum equivalent plastic
! strain allowed within a time-step is 15%
!
kbc,0 ! Ramped loading within a load step
antype,4 ! Transient analysis
nlgeom,on ! Activate large-deformation effects
timint,off,struc ! Structural dynamic effects are disabled
nropt,unsym ! Use full Newton-Raphson with
! unsymmetric matrices of elements