/COM,ANSYS MEDIA REL. 182 (07/10/2017) REF. VERIF. MANUAL: REL. 182 /verify,vmr020-t1a-183 /title,vmr020-t1a-183,Centre Cracked Plate in Tension /com, /com, Problem is taken from NAFEMS Publication /com, "2D Test Cases in Linear Elastic Fracture Mechanics" /com, Test case 1.1 /com, /com, Reference: Rooke D P and Cartwright D J : Compendium /com, of stress intensity factors, HMSO, London, England (1976) /com, /com, ********************************************************** /com, Stress Intensity Factor Calculation using Interaction /com, Integral Approach /prep7 E=207000 ! youngs modulus NU=0.3 ! poissons ratio sig=100 ! surface load pi=3.141593 a=10 ! crack length et,1,plane183 ! plane 183 element keyopt,1,3,2 ! plane strain mp,ex,1,e mp,nuxy,1,nu k,1,-10,0 k,2,0,0 k,3,10,0 k,4,10,10 k,5,10,20 k,6,-10,20 k,7,-10,10 l,1,2 *rep,6,1,1 l,7,1 l,4,7 al,1,2,3,8,7 al,4,5,6,8 esize,1 kscon,2,1,1,4,0.75 !crack tip elements amesh,1 esize,2 amesh,2 fini /solu autots,on nsubst,10 outres,all,all nsel,s,loc,y,0 nsel,r,loc,x,0,10 d,all,uy,0 nsel,s,loc,x,-10 nsel,r,loc,y,0,20 d,all,ux,0 nsel,all lsel,s,line,,5 sfl,all,press,-sig lsel,all nsel,s,loc,y,0 nsel,r,loc,x,0 cm,crack1,node ! define the crack tip node component nsel,all cint,new,1 cint,type,sifs ! Calculate Stress Intensity factor cint,ctnc,crack1 ! crack ID cint,ncon,4 ! number of countours cint,symm,on ! symmetry on cint,norm,0,2 cint,list allsel,all solve fini /out,scratch /post1 prcint,1 ! Get the J1,J2,J3 values *get,k1_1,cint,1,ctip,node(0,0,0),,1,dtype,k1 *get,k1_2,cint,1,ctip,node(0,0,0),,2,dtype,k1 *get,k1_3,cint,1,ctip,node(0,0,0),,3,dtype,k1 *get,k1_4,cint,1,ctip,node(0,0,0),,4,dtype,k1 k1=(k1_2+k1_3+k1_4)/3 *stat,k1 con1 = ((pi*a)**0.5) k0=(sig*con1) norm_sif=k1/k0 /out, *status,norm_sif *DIM,LABEL,CHAR,1,5 *DIM,VALUE,,1,3 LABEL(1,1) = 'KI' *VFILL,VALUE(1,1),DATA,1.325 *VFILL,VALUE(1,2),DATA,norm_sif *VFILL,VALUE(1,3),DATA,ABS(norm_sif/1.325 ) SAVE,TABLE_1 FINI /CLEAR,NOSTART /com,************************************************************* /com, Using J integral Calculation /prep7 E=207000 ! youngs modulus NU=0.3 ! poissons ratio sig=100 ! surface load pi=3.141593 a=10 ! crack length et,1,plane183 ! plane 183 element keyopt,1,3,2 ! plane strain mp,ex,1,e mp,nuxy,1,nu k,1,-10,0 k,2,0,0 k,3,10,0 k,4,10,10 k,5,10,20 k,6,-10,20 k,7,-10,10 l,1,2 *rep,6,1,1 l,7,1 l,4,7 al,1,2,3,8,7 al,4,5,6,8 esize,1 kscon,2,1,1,4,0.75 ! mesh crack tip elements amesh,1 esize,2 amesh,2 fini /solu autots,on nsubst,10 outres,all,all nsel,s,loc,y,0 nsel,r,loc,x,0,10 d,all,uy,0 nsel,s,loc,x,-10 nsel,r,loc,y,0,20 d,all,ux,0 nsel,all lsel,s,line,,5 sfl,all,press,-sig lsel,all nsel,s,loc,y,0 nsel,r,loc,x,0 cm,crack1,node ! define the crack tip node component nsel,all cint,new,1 cint,ctnc,crack1 ! crack ID cint,ncon,4 ! number of countours cint,symm,on ! symmetry on cint,norm,0,2 cint,list allsel,all solve fini /out,scratch /post1 prcint,1 ! Get the J1,J2,J3 values *get,j1,cint,1,ctip,node(0,0,0),,1,, *get,j2,cint,1,ctip,node(0,0,0),,2,, *get,j3,cint,1,ctip,node(0,0,0),,3,, *get,j4,cint,1,ctip,node(0,0,0),,4,, jc1 =(abs(j1)+abs(j2)+abs(j3)+abs(j4))/4 *stat,jc1 con1 = ((pi*a)**0.5) con2 = E/(1-(nu*nu)) k1 = ((con2*jc1)**0.5) k0=(sig*con1) norm_sif=k1/k0 /out, *status,norm_sif *DIM,LABEL,CHAR,1,5 *DIM,VALUE,,1,3 LABEL(1,1) = 'KI' *VFILL,VALUE(1,1),DATA,1.325 *VFILL,VALUE(1,2),DATA,norm_sif *VFILL,VALUE(1,3),DATA,ABS(norm_sif/1.325 ) SAVE,TABLE_2 /NOPR /COM /OUT,vmr020-t1a-183,vrt /COM,------------------- vmr020-t1a-183 RESULTS COMPARISON --------------------- /COM, /COM, | TARGET | MECHANICAL APDL | RATIO /COM, RESUME,TABLE_1 /COM,USING STRESS INTENSITY FACTOR CALCULATION *VWRITE,LABEL(1,1),VALUE(1,1),VALUE(1,2),VALUE(1,3) (1X,A8,' ',F10.3,' ',F12.3,' ',1F16.3) /COM, /COM, /COM, RESUME,TABLE_2 /COM,USING J-INTEGRAL APPROACH /COM, *VWRITE,LABEL(1,1),VALUE(1,1),VALUE(1,2),VALUE(1,3) (1X,A8,' ',F10.3,' ',F12.3,' ',1F16.3) /COM, /COM, /COM, /COM,------------------------------------------------------------------------------- /OUT FINISH *list,vmr020-t1a-183,vrt