/COM,ANSYS MEDIA REL. 182 (07/10/2017) REF. VERIF. MANUAL: REL. 182 /verify,vmr020-t2a-183 /title,vmr020-t2a-183,Edge cracked plate with uniform tensile stress /com, /com, Problem is taken from NAFEMS Publication /com, "2D Test Cases in Linear Elastic Fracture Mechanics" /com, Test case 2.1 /com, /com, Reference: Rooke D P and Cartwright D J : Compendium /com, of stress intensity factors, HMSO, London, England (1976) /com, /com, ********************************************************** /com, Stress Intensity Factor Calculation using Interaction /com, Integral Approach /prep7 E=207000 ! youngs modulus NU=0.3 ! poissons ratio sig=100 ! surface load pi=3.141593 a=10 !crack length et,1,plane183 ! Plane183 element keyopt,1,3,2 ! Plane strain element mp,ex,1,e mp,nuxy,1,nu k,1,-10,, k,2,,, k,3,10,0 k,4,10,10 k,5,-10,10 l,1,2 *rep,4,1,1 l,5,1 al,1,2,3,4,5 esize,10 kscon,2,4,1,4,0.75 ! crack tip elements amesh,1 finish /solu autots,on nsubst,10 outres,all,all nsel,s,loc,y,0 nsel,r,loc,x,0,10 d,all,uy,0 nsel,r,loc,x,10 d,all,ux,0 nsel,all lsel,s,line,,4 sfl,all,press,-sig lsel,all nsel,s,loc,y,0 nsel,r,loc,x,0 cm,crack1,node ! define the crack tip node component nsel,all cint,new,1 cint,type,sifs ! calculate stress intensity factors cint,ctnc,crack1 ! crack ID cint,ncon,3 ! number of countours cint,symm,on ! symmetry on cint,norm,0,2 cint,list allsel,all solve fini /out,scratch /post1 prcint,1,,k1 *get,k_1,cint,1,ctip,node(0,0,0),,1,dtype,k1 *get,k_2,cint,1,ctip,node(0,0,0),,2,dtype,k1 *get,k_3,cint,1,ctip,node(0,0,0),,3,dtype,k1 con1 = ((pi*a)**0.5) k1=(k_1+k_2+k_3)/3 k0=(sig*con1) norm_sif=k1/k0 /out, *stat,norm_sif *DIM,LABEL,CHAR,1,5 *DIM,VALUE,,1,3 LABEL(1,1) = 'KI' *VFILL,VALUE(1,1),DATA,3 *VFILL,VALUE(1,2),DATA,norm_sif *VFILL,VALUE(1,3),DATA,ABS(norm_sif/3 ) SAVE,TABLE_1 FINI /CLEAR,NOSTART /com,************************************************************* /com, Using J integral Calculation /prep7 E=207000 ! youngs modulus NU=0.3 ! poissons ratio sig=100 ! surface load pi=3.141593 a=10 !crack length et,1,plane183 ! Plane183 element keyopt,1,3,2 ! Plane strain element mp,ex,1,e mp,nuxy,1,nu k,1,-10,, k,2,,, k,3,10,0 k,4,10,10 k,5,-10,10 l,1,2 *rep,4,1,1 l,5,1 al,1,2,3,4,5 esize,10 kscon,2,4,1,4,0.75 ! crack tip elements amesh,1 fini /solu autots,on nsubst,10 outres,all,all nsel,s,loc,y,0 nsel,r,loc,x,0,10 d,all,uy,0 nsel,r,loc,x,10 d,all,ux,0 nsel,all lsel,s,line,,4 sfl,all,press,-sig lsel,all nsel,s,loc,y,0 nsel,r,loc,x,0 cm,crack1,node ! define the crack tip node component nsel,all cint,new,1 cint,ctnc,crack1 ! crack ID cint,ncon,3 ! number of countours cint,symm,on ! symmetry on cint,norm,0,2 cint,list allsel,all solve fini /out,scratch /post1 prcint,1 ! Get the J1,J2,J3 values *get,j1,cint,1,ctip,node(0,0,0),,1,, *get,j2,cint,1,ctip,node(0,0,0),,2,, *get,j3,cint,1,ctip,node(0,0,0),,3,, jc1 =(abs(j1)+abs(j2)+abs(j3))/3 *stat,jc1 con1 = ((pi*a)**0.5) con2 = E/(1-(nu*nu)) K1 = ((con2*jc1)**0.5) k0=(sig*con1) norm_sif = K1/k0 /out, *status,norm_sif *DIM,LABEL,CHAR,1,5 *DIM,VALUE,,1,3 LABEL(1,1) = 'KI' *VFILL,VALUE(1,1),DATA,3 *VFILL,VALUE(1,2),DATA,norm_sif *VFILL,VALUE(1,3),DATA,ABS(norm_sif/3 ) SAVE,TABLE_2 /NOPR /COM /OUT,vmr020-t2a-183,vrt /COM,------------------- vmr020-t2a-183 RESULTS COMPARISON --------------------- /COM, /COM, | TARGET | MECHANICAL APDL | RATIO /COM, RESUME,TABLE_1 /COM,USING STRESS INTENSITY FACTOR CALCULATION *VWRITE,LABEL(1,1),VALUE(1,1),VALUE(1,2),VALUE(1,3) (1X,A8,' ',F10.3,' ',F12.3,' ',1F16.3) /COM, /COM, /COM, RESUME,TABLE_2 /COM,USING J-INTEGRAL APPROACH /COM, *VWRITE,LABEL(1,1),VALUE(1,1),VALUE(1,2),VALUE(1,3) (1X,A8,' ',F10.3,' ',F12.3,' ',1F16.3) /COM, /COM, /COM, /COM,------------------------------------------------------------------------------- /OUT FINISH *list,vmr020-t2a-183,vrt