/COM,ANSYS MEDIA REL. 182 (07/10/2017) REF. VERIF. MANUAL: REL. 182 /verify,vmr020-t4a-183 /title,vmr020-t4a-183,Crack at a hole in a plate (Uniaxial tension) /com, /com, Problem is taken from NAFEMS Publication /com, "2D Test Cases in Linear Elastic Fracture Mechanics" /com, Test case 4.1 /com, /com, Reference: Rooke D P and Cartwright D J : Compendium /com, of stress intensity factors, HMSO, London, England (1976) /com, /com, ********************************************************** /com, Stress Intensity Factor Calculation using Interaction /com, Integral Approach /prep7 e=207000 !youngs modulus nu=0.3 !poissons ratio sig=100 !surface load a=3 !crack length pi=3.141593 et,1,plane183,,,0 !plane183 elements mp,ex,1,e mp,nuxy,1,nu k,1,3,0 k,2,10,0 k,3,10,20 k,4,0,20 k,5,0,2.5 k,6,2.5,0 k,7,10,5 k,8,0,5 l,1,2 l,2,7 l,7,3 l,3,4 l,4,8 l,8,5 csys,2 l,5,6 csys,0 l,6,1 l,7,8 al,1,2,9,6,7,8 al,3,4,5,9 esize,1 amesh,2 kscon,1,0.15,1,4,0.75 !crack tip elements esize,1 amesh,1 finish /solu autots,on nsubst,10 outres,all,all nsel,s,loc,x,3,10 nsel,r,loc,y,0 d,all,uy,0 nsel,all nsel,s,loc,y,2.5,20 nsel,r,loc,x,0 d,all,ux,0 nsel,all sfl,4,press,-sig nsel,s,loc,x,3 nsel,r,loc,y,0 cm,crack1,node !define crack tip node component cint,new,1 cint,type,sifs ! calculate stress intensity factor cint,ctnc,crack1 !crack ID cint,ncon,4 !number of contours cint,symm,on !symmetry on cint,norm,0,2 cint,list allsel,all solve finish /out,scratch /post1 prcint,1 *get,k1_1,cint,1,ctip,node(3,0,0),,1,dtype,k1 *get,k1_2,cint,1,ctip,node(3,0,0),,2,dtype,k1 *get,k1_3,cint,1,ctip,node(3,0,0),,3,dtype,k1 con1 = ((pi*a)**0.5) k1=(k1_1+k1_2+k1_3)/3 k0=(sig*con1) norm_sif=k1/k0 /out, *stat,norm_sif *DIM,LABEL,CHAR,1,5 *DIM,VALUE,,1,3 LABEL(1,1) = 'KI' *VFILL,VALUE(1,1),DATA,1.050 *VFILL,VALUE(1,2),DATA,norm_sif *VFILL,VALUE(1,3),DATA,ABS(norm_sif/1.050 ) SAVE,TABLE_1 FINI /CLEAR,NOSTART /com,************************************************************* /com, Using J integral Calculation /prep7 e=207000 !youngs modulus nu=0.3 !poissons ratio sig=100 !surface load a=3 !crack length pi=3.141593 et,1,plane183,,,0 !plane183 elements mp,ex,1,e mp,nuxy,1,nu k,1,3,0 k,2,10,0 k,3,10,20 k,4,0,20 k,5,0,2.5 k,6,2.5,0 k,7,10,5 k,8,0,5 l,1,2 l,2,7 l,7,3 l,3,4 l,4,8 l,8,5 csys,2 l,5,6 csys,0 l,6,1 l,7,8 al,1,2,9,6,7,8 al,3,4,5,9 esize,1 amesh,2 kscon,1,0.15,1,4,0.75 !crack tip elements esize,1 amesh,1 finish /solu autots,on nsubst,10 outres,all,all nsel,s,loc,x,3,10 nsel,r,loc,y,0 d,all,uy,0 nsel,all nsel,s,loc,y,2.5,20 nsel,r,loc,x,0 d,all,ux,0 nsel,all sfl,4,press,-sig nsel,s,loc,x,3 nsel,r,loc,y,0 cm,crack1,node !define crack tip node component cint,new,1 cint,ctnc,crack1 !crack ID cint,ncon,4 !number of contours cint,symm,on !symmetry on cint,norm,0,2 cint,list allsel,all solve finish /out,scratch /post1 prcint,1 *get,j1,cint,1,ctip,node(3,0,0),,1,,, *get,j2,cint,1,ctip,node(3,0,0),,2,,, *get,j3,cint,1,ctip,node(3,0,0),,3,,, *get,j4,cint,1,ctip,node(3,0,0),,4,,, j_avg=(abs(j1)+abs(j2)+abs(j3)+abs(j4))/4 *stat,j_avg con1 = ((pi*a)**0.5) con2 = E k1 = ((con2*j_avg)**0.5) k0=(sig*con1) norm_sif=k1/k0 /out, *stat,norm_sif *DIM,LABEL,CHAR,1,5 *DIM,VALUE,,1,3 LABEL(1,1) = 'KI' *VFILL,VALUE(1,1),DATA,1.050 *VFILL,VALUE(1,2),DATA,norm_sif *VFILL,VALUE(1,3),DATA,ABS(norm_sif/1.050 ) SAVE,TABLE_2 /NOPR /COM /OUT,vmr020-t4a-183,vrt /COM,------------------- vmr020-t4a-183 RESULTS COMPARISON --------------------- /COM, /COM, | TARGET | MECHANICAL APDL | RATIO /COM, RESUME,TABLE_1 /COM,USING STRESS INTENSITY FACTOR CALCULATION *VWRITE,LABEL(1,1),VALUE(1,1),VALUE(1,2),VALUE(1,3) (1X,A8,' ',F10.3,' ',F12.3,' ',1F16.3) /COM, /COM, /COM, RESUME,TABLE_2 /COM,USING J-INTEGRAL APPROACH /COM, *VWRITE,LABEL(1,1),VALUE(1,1),VALUE(1,2),VALUE(1,3) (1X,A8,' ',F10.3,' ',F12.3,' ',1F16.3) /COM, /COM, /COM, /COM,------------------------------------------------------------------------------- /OUT FINISH *list,vmr020-t4a-183,vrt