/COM,ANSYS MEDIA REL. 182 (07/10/2017) REF. VERIF. MANUAL: REL. 182 /verify,vmr020-t5a-183 /title,vmr020-t5a-183,Axisymmetric crack in a bar /com, /com, Problem is taken from NAFEMS Publication /com, "2D Test Cases in Linear Elastic Fracture Mechanics" /com, Test case 5.0 /com, /com, Reference: Murakami Y: Stress intensity factor handbook /com, Pergamon Press (1987) /com, /com, ********************************************************** /com, Stress Intensity Factor Calculation using Interaction /com, Integral Approach /prep7 e=207000 !youngs modulus nu=0.3 !poissons ratio a=10 !crack length b=10 sig=100 !sufrace load r=20 !radius of the bar pi=3.141593 et,1,plane183,,,1 !plane183 elements, axisymmetric mp,ex,1,e mp,nuxy,1,nu k,1,10,0 k,2,0,0 k,3,0,10 k,4,0,30 k,5,20,30 k,6,20,10 k,7,20,0 l,1,2 *rep,6,1,1 l,7,1 l,3,6 al,1,2,8,6,7 al,3,4,5,8 esize,1 kscon,1,0.75,1,8,0.75 !crack tip elements amesh,1 esize,2 amesh,2 allsel cskp,12,0,3,6,2 csys,0 fini /solu autots,on nsubst,10 outres,all,all nsel,s,loc,x,0,10 nsel,r,loc,y,0 d,all,uy,0 nsel,all nsel,s,loc,y,0,30 nsel,r,loc,x,0 d,all,ux,0 nsel,all lsel,s,line,,4 sfl,all,press,-sig lsel,all nsel,s,loc,x,10 nsel,r,loc,y,0 cm,crack1,node !define crack tip node components cint,new,1 cint,type,sifs ! calculate stress intensity factor cint,ctnc,crack1 !crack ID cint,ncon,5 !number of contours cint,symm,on !symmetry on cint,norm,12,2 cint,list allsel,all solve finish /out,scratch /post1 prcint,1,,k1 *get,k1_1,cint,1,ctip,node(10,0,0),,1,dtype,k1 *get,k1_2,cint,1,ctip,node(10,0,0),,2,dtype,k1 *get,k1_3,cint,1,ctip,node(10,0,0),,3,dtype,k1 *get,k1_4,cint,1,ctip,node(10,0,0),,4,dtype,k1 *get,k1_5,cint,1,ctip,node(10,0,0),,5,dtype,k1 con1 = ((pi*b)**0.5) P=(sig*pi*r*r) con2=(pi*b*b) k1=(k1_2+k1_3+k1_4+k1_5)/4 *stat,k1 k0=P*con1/con2 *stat,k0 norm_sif=k1/k0 /out, *stat,norm_sif *DIM,LABEL,CHAR,1,5 *DIM,VALUE,,1,3 LABEL(1,1) = 'KI' *VFILL,VALUE(1,1),DATA,0.475 *VFILL,VALUE(1,2),DATA,norm_sif *VFILL,VALUE(1,3),DATA,ABS(norm_sif/0.475 ) SAVE,TABLE_1 FINI /CLEAR,NOSTART /com,************************************************************* /com, Using J integral Calculation (plane strain formulation) /prep7 e=207000 !youngs modulus nu=0.3 !poissons ratio a=10 !crack length b=10 sig=100 !sufrace load r=20 !radius of the bar pi=3.141593 et,1,plane183,,,1 !plane183 elements, axisymmetric mp,ex,1,e mp,nuxy,1,nu k,1,10,0 k,2,0,0 k,3,0,10 k,4,0,30 k,5,20,30 k,6,20,10 k,7,20,0 l,1,2 *rep,6,1,1 l,7,1 l,3,6 al,1,2,8,6,7 al,3,4,5,8 esize,1 kscon,1,0.75,1,8,0.75 !crack tip elements amesh,1 esize,2 amesh,2 allsel cskp,12,0,3,6,2 csys,0 fini /solu autots,on nsubst,10 outres,all,all nsel,s,loc,x,0,10 nsel,r,loc,y,0 d,all,uy,0 nsel,all nsel,s,loc,y,0,30 nsel,r,loc,x,0 d,all,ux,0 nsel,all lsel,s,line,,4 sfl,all,press,-sig lsel,all nsel,s,loc,x,10 nsel,r,loc,y,0 cm,crack1,node !define crack tip node component cint,new,1 cint,ctnc,crack1 !crack ID cint,ncon,5 !number of contours cint,symm,on !symmetry on cint,norm,12,2 cint,list allsel,all solve finish /out,scratch /post1 prcint,1,, *get,j_1,cint,1,ctip,node(10,0,0),,1,, *get,j_2,cint,1,ctip,node(10,0,0),,2,, *get,j_3,cint,1,ctip,node(10,0,0),,3,, *get,j_4,cint,1,ctip,node(10,0,0),,4,, *get,j_5,cint,1,ctip,node(10,0,0),,5,, con1 = ((pi*b)**0.5) P=(sig*pi*r*r) con2=(pi*b*b) j=(abs(j_1)+abs(j_2)+abs(j_3)+abs(j_4)+abs(j_5))/5 *stat,j con3=e/(1-nu**2) !plane strain formulation k1=(j*con3)**0.5 k0=P*con1/con2 *stat,k0 norm_sif=k1/k0 /out, *stat,norm_sif *DIM,LABEL,CHAR,1,5 *DIM,VALUE,,1,3 LABEL(1,1) = 'KI' *VFILL,VALUE(1,1),DATA,0.475 *VFILL,VALUE(1,2),DATA,norm_sif *VFILL,VALUE(1,3),DATA,ABS(norm_sif/0.475 ) SAVE,TABLE_2 FINI /CLEAR,NOSTART /com,************************************************************* /com, Using J integral Calculation (plane stress formulation) /prep7 e=207000 !youngs modulus nu=0.3 !poissons ratio a=10 !crack length b=10 sig=100 !sufrace load r=20 !radius of the bar pi=3.141593 et,1,plane183,,,1 !plane183 elements, axisymmetric mp,ex,1,e mp,nuxy,1,nu k,1,10,0 k,2,0,0 k,3,0,10 k,4,0,30 k,5,20,30 k,6,20,10 k,7,20,0 l,1,2 *rep,6,1,1 l,7,1 l,3,6 al,1,2,8,6,7 al,3,4,5,8 esize,1 kscon,1,0.75,1,8,0.75 !crack tip elements amesh,1 esize,2 amesh,2 allsel cskp,12,0,3,6,2 csys,0 fini /solu autots,on nsubst,10 outres,all,all nsel,s,loc,x,0,10 nsel,r,loc,y,0 d,all,uy,0 nsel,all nsel,s,loc,y,0,30 nsel,r,loc,x,0 d,all,ux,0 nsel,all lsel,s,line,,4 sfl,all,press,-sig lsel,all nsel,s,loc,x,10 nsel,r,loc,y,0 cm,crack1,node !define crack tip node components cint,new,1 cint,ctnc,crack1 !crack ID cint,ncon,5 !number of contours cint,symm,on !symmetry on cint,norm,12,2 cint,list allsel,all solve finish /out,scratch /post1 prcint,1,, *get,j_1,cint,1,ctip,node(10,0,0),,1,, *get,j_2,cint,1,ctip,node(10,0,0),,2,, *get,j_3,cint,1,ctip,node(10,0,0),,3,, *get,j_4,cint,1,ctip,node(10,0,0),,4,, *get,j_5,cint,1,ctip,node(10,0,0),,5,, con1 = ((pi*b)**0.5) P=(sig*pi*r*r) con2=(pi*b*b) j=(abs(j_1)+abs(j_2)+abs(j_3)+abs(j_4)+abs(j_5))/5 *stat,j con3=e !plane stress formulation k1=(j*con3)**0.5 k0=P*con1/con2 *stat,k0 norm_sif=k1/k0 /out, *stat,norm_sif *DIM,LABEL,CHAR,1,5 *DIM,VALUE,,1,3 LABEL(1,1) = 'KI' *VFILL,VALUE(1,1),DATA,0.475 *VFILL,VALUE(1,2),DATA,norm_sif *VFILL,VALUE(1,3),DATA,ABS(norm_sif/0.475 ) SAVE,TABLE_3 /NOPR /COM /OUT,vmr020-t5a-183,vrt /COM,------------------- vmr020-t5a-183 RESULTS COMPARISON --------------------- /COM, /COM, | TARGET | MECHANICAL APDL | RATIO /COM, RESUME,TABLE_1 /COM,USING STRESS INTENSITY FACTOR CALCULATION *VWRITE,LABEL(1,1),VALUE(1,1),VALUE(1,2),VALUE(1,3) (1X,A8,' ',F10.3,' ',F12.3,' ',1F16.3) /COM, /COM, /COM, RESUME,TABLE_2 /COM,USING J-INTEGRAL APPROACH - PLANE STRAIN FORMULATION /COM, *VWRITE,LABEL(1,1),VALUE(1,1),VALUE(1,2),VALUE(1,3) (1X,A8,' ',F10.3,' ',F12.3,' ',1F16.3) /COM, /COM, /COM, RESUME,TABLE_3 /COM,USING J-INTEGRAL APPROACH - PLANE STRESS FORMULATION /COM, *VWRITE,LABEL(1,1),VALUE(1,1),VALUE(1,2),VALUE(1,3) (1X,A8,' ',F10.3,' ',F12.3,' ',1F16.3) /COM, /COM, /COM,------------------------------------------------------------------------------- /OUT FINISH *list,vmr020-t5a-183,vrt