/COM,ANSYS MEDIA REL. 182 (07/10/2017) REF. VERIF. MANUAL: REL. 182 /verify,vmr020-t6a-183 /title,vmr020-t6a-183,Compact tension specimen /com, /com, Problem is taken from NAFEMS Publication /com, "2D Test Cases in Linear Elastic Fracture Mechanics" /com, Test case 6.0 /com, /com, Reference: Murakami Y: Stress intensity factor handbook /com, Pergamon Press (1987) /com, /com, ********************************************************** /com, Stress Intensity Factor Calculation using Interaction /com, Integral Approach /prep7 e=207000 !youngs modulus nu=.3 !poissons ratio P=1000 !point load t=1 !thickness w=50 !width et,1,plane183,,,2 !plane183 elements, plane strain mp,ex,1,e mp,nuxy,1,nu k,1,, k,2,25, k,3,25,6.875 k,4,25,13.75 k,5,25,30 k,6,-37.5,30 k,7,-37.5,13.75 k,8,-37.5,6.875 k,9,-25,6.875 k,10,-25,2 k,11,-18,2 k,12,-18,0 k,13,-25,13.75 l,1,2 *rep,11,1,1 l,12,1 l,9,3 l,7,13 l,13,4 al,1,2,13,9,10,11,12 al,3,15,14,7,8,13 al,4,5,6,14,15 esize,12.5 amesh,2 amesh,3 kscon,1,2,1,4,0.75 !crack tip elements esize,12.5 amesh,1 fini /solu autots,on nsubst,10 outres,all,all nsel,s,loc,y,0 nsel,r,loc,x,0,25 d,all,uy,0 nsel,r,loc,x,25 d,all,ux,0 nsel,all fk,13,fy,P nsel,s,loc,x,0 nsel,r,loc,y,0 cm,crack1,node !define crack tip node components cint,new,1 cint,type,sifs ! calculate stress intensity factors cint,name,crack1 !crack ID cint,ncon,4 !number of contours cint,symm,on !symmetry on cint,norm,0,2 cint,list allsel,all solve fini /out,scratch /post1 prcint,1 *get,k1_1,cint,1,ctip,node(0,0,0),,1,dtype,k1 *get,k1_2,cint,1,ctip,node(0,0,0),,2,dtype,k1 *get,k1_3,cint,1,ctip,node(0,0,0),,3,dtype,k1 *get,k1_4,cint,1,ctip,node(0,0,0),,4,dtype,k1 k1_avg=(k1_1+k1_2+k1_3+k1_4)/4 k0=P/(t*(w)**0.5) norm_sif=k1_avg/k0 /out, *stat,norm_sif *DIM,LABEL,CHAR,1,5 *DIM,VALUE,,1,3 LABEL(1,1) = 'KI' *VFILL,VALUE(1,1),DATA,9.659 *VFILL,VALUE(1,2),DATA,norm_sif *VFILL,VALUE(1,3),DATA,ABS(norm_sif/9.659 ) SAVE,TABLE_1 FINI /CLEAR,NOSTART /com,************************************************************* /com, Using J integral Calculation /prep7 e=207000 !youngs modulus nu=.3 !poissons ratio P=1000 !point load t=1 !thickness w=50 !width et,1,plane183,,,2 !plane183 elements, plane strain mp,ex,1,e mp,nuxy,1,nu k,1,, k,2,25, k,3,25,6.875 k,4,25,13.75 k,5,25,30 k,6,-37.5,30 k,7,-37.5,13.75 k,8,-37.5,6.875 k,9,-25,6.875 k,10,-25,2 k,11,-18,2 k,12,-18,0 k,13,-25,13.75 l,1,2 *rep,11,1,1 l,12,1 l,9,3 l,7,13 l,13,4 al,1,2,13,9,10,11,12 al,3,15,14,7,8,13 al,4,5,6,14,15 esize,12.5 amesh,2 amesh,3 kscon,1,2,1,4,0.75 !crack tip elements esize,12.5 amesh,1 fini /solu autots,on nsubst,10 outres,all,all nsel,s,loc,y,0 nsel,r,loc,x,0,25 d,all,uy,0 nsel,r,loc,x,25 d,all,ux,0 nsel,all fk,13,fy,P nsel,s,loc,x,0 nsel,r,loc,y,0 cm,crack1,node !define crack tip node components cint,new,1 cint,ctnc,crack1 !crack ID cint,ncon,4 !number of contours cint,symm,on !symmetry on cint,norm,0,2 cint,list allsel,all solve fini /out,scratch /post1 prcint,1 *get,j1,cint,1,ctip,node(0,0,0),,1,, *get,j2,cint,1,ctip,node(0,0,0),,2,, *get,j3,cint,1,ctip,node(0,0,0),,3,, *get,j4,cint,1,ctip,node(0,0,0),,4,, j_avg=(abs(j1)+abs(j2)+abs(j3)+abs(j4))/4 con2 = E/(1-(nu*nu)) k1 = ((con2*j_avg)**0.5) k0=P/(t*(w)**0.5) norm_sif=k1/k0 /out, *stat,norm_sif *DIM,LABEL,CHAR,1,5 *DIM,VALUE,,1,3 LABEL(1,1) = 'KI' *VFILL,VALUE(1,1),DATA,9.659 *VFILL,VALUE(1,2),DATA,norm_sif *VFILL,VALUE(1,3),DATA,ABS(norm_sif/9.659 ) SAVE,TABLE_2 /NOPR /COM /OUT,vmr020-t6a-183,vrt /COM,------------------- vmr020-t6a-183 RESULTS COMPARISON --------------------- /COM, /COM, | TARGET | MECHANICAL APDL | RATIO /COM, RESUME,TABLE_1 /COM,USING STRESS INTENSITY FACTOR CALCULATION *VWRITE,LABEL(1,1),VALUE(1,1),VALUE(1,2),VALUE(1,3) (1X,A8,' ',F10.3,' ',F12.3,' ',1F16.3) /COM, /COM, /COM, RESUME,TABLE_2 /COM,USING J-INTEGRAL APPROACH /COM, *VWRITE,LABEL(1,1),VALUE(1,1),VALUE(1,2),VALUE(1,3) (1X,A8,' ',F10.3,' ',F12.3,' ',1F16.3) /COM, /COM, /COM, /COM,------------------------------------------------------------------------------- /OUT FINISH *list,vmr020-t6a-183,vrt