3.47. PRIN

The PRIN command specifies the reports to be printed.

Parameters

PRIN : Keyword.
type : Keyword indicating type of report required or units to be used. See table below for available keywords.
params : Additional parameters applicable to each type:

Table 3.2:  PRINT Command Parameters

Type Meaning Additional Parameters
XCHK Input Data Cross Check ReportNone
PROP Member Geometry and Material Property ReportNone
FORC Member Force ReportNone
STRE Member Stress ReportNone
UNCK Unity Check ReportNone
SUM1 Highest yield and buckle combined stress unity checks ex1, ex2 specify exceedence values (report SUM4 only) FAIL report failed members only BOTH print both full summary and failed member reports uclim utilization limit for failure reports
SUM2 Highest buckle check plus all unity checks at section with highest yield combined stress unity checkSee SUM1 above
SUM3 Highest unity checkSee SUM1 above
SUM4 3 worst unity checks plus distribution of unity check valuesSee SUM1 above
SUM5 Highest member forces and momentsSee SUM1 above
FUNI Change force units in reportsname1 length unit name2 force unit
SUNI Change stress units in reportsname1 length unit name2 force unit
All Print all appropriate reportsNone

Usage

Optional - for defaults see Note 8 below.

Notes

  1. The reports applicable to each type of Code Check are given in each of the tables: Table 3.3: Output Reports Available for API/AISC Code Checks, Table 3.4: Output Reports Available for European Code Checks, Table 3.5: Output Reports Available for International Standards Code Checks.

  2. BEAMST automatically filters out requested reports which are not available for the type of check/post-processing selected. Such redundant requests do not induce data or execution errors.

  3. Exceedence values are only appropriate for summary report number 4 (SUM4) and if omitted default to 1.0 and 0.5.

  4. Utilization limits are available for summary reports 1-4. For summary report number 4 (SUM4), the exceedence values MUST precede BOTH/FAIL.

  5. If units are specified both length and force units must be supplied. The valid unit names are listed under the UNIT command. These units override any results units defined in the Preliminary data (see UNIT).

  6. FUNI is only valid for NPD Unity Check Reports.

  7. If this command is omitted, the following defaults apply:

    CommandDefault
    AISC WSD ALLOPRIN SUM1
    AISC LRFD MEMB
    API WSD ALLO
    API LRFD MEMB
    API WSD HYDR
    API LRFD HYDR
    NORS MEMB
    NORS HYDR
    API WSD PUNCPRIN SUM3
    API WSD NOMI
    API LRFD JOIN
    NPD JOIN
    NORS JOIN
    DS449No Default
    POST
    ANPD MEMB
    BS59

Output Reports

BEAMST has a number of different types of output reports that may be printed selectively using the PRIN command. The reports available are described in the following sections and are summarized in the following tables.

Note, if the command PRIN ALL is used then all available reports for the given Code Check will be output.

Table 3.3:  Output Reports Available for API/AISC Code Checks

ReportAISC/API WSD ALLO AISC LRFD MEMB API WSD HYDR API WSD NOMI (< ED21) API WSD PUNC (< ED21) API WSD JOIN (> ED21) API LRFD MEMB API LRFD HYDR API LRFD JOIN

Data Echo

Y

Y

Y

Y

Y

Y

Y

Y

Y

Command Summary

Y

Y

Y

Y

Y

Y

Y

Y

Y

Cross Check

Y

Y

Y

Y

Y

Y

Y

Y

Y

Member Properties

Y

Y

Y

-

-

-

Y

Y

-

Member Force

Y

Y

Y

-

-

-

Y

Y

-

Member Stress

Y

Y

Y

-

-

-

Y

Y

-

Unity Check

Y

Y

Y

Y

Y

Y

Y

Y

Y

Summary Reports          

No. 1

Y

Y

Y

-

-

-

Y

Y

Y

No. 1 (FAIL)

Y

Y

Y

-

-

-

Y

Y

Y

No. 2

Y

-

-

-

-

-

-

-

-

No. 2 (FAIL)

Y

-

-

-

-

-

-

-

-

No. 3

Y

Y

-

Y

Y

Y

Y

-

Y

No. 3 (FAIL)

Y

Y

-

Y

Y

Y

Y

-

Y

No. 4

Y

-

-

Y

Y

Y

-

-

-

No. 4 (FAIL)

Y

-

-

Y

Y

Y

-

-

-

No. 5

-

-

-

-

-

-

-

-

-


Table 3.4:  Output Reports Available for European Code Checks

ReportBS59MEMBDS449MEMBDS449JOINNPDMEMBNPD JOINNORSOKMEMBNORSOKHYDRNORSOKJOINPOST
Data EchoYYYYYYYYY
Command SummaryYYYYYYYYY
Cross Check YYYYYYYYY
Member Properties YY-Y-YY-Y
Member ForceYY-Y-YY-Y
Member Stress YY-Y-YY-Y
Unity Check Y YYYYY YY-
Summary Reports          

No. 1

No. 1 (FAIL)

No. 2

No. 2 (FAIL)

No. 3

No. 3 (FAIL)

No. 4

No. 4 (FAIL)

No. 5

Y

Y

-

-

Y

Y

Y

Y

-

Y

Y

-

-

Y

Y

Y

Y

-

-

-

-

-

Y

Y

Y

Y

-

Y

Y

-

-

Y

Y

Y

Y

-

-

-

-

-

Y

Y

Y

Y

-

Y

Y

-

-

Y

Y

-

-

-

Y

Y

-

-

-

-

-

-

-

Y

Y

-

-

Y

Y

-

-

-

-

-

-

-

-

-

-

-

Y


Table 3.5:  Output Reports Available for International Standards Code Checks

ReportISO MEMBISO HYDRISO JOIN
Data EchoYYY
Command SummarYYY
Cross Check YYY
Member Properties YY-
Member Force YY-
Member StressYY-
Unity Check YYY
Summary Reports    

No. 1

No. 1 (FAIL)

No. 2

No. 2 (FAIL)

No. 3

No. 3 (FAIL)

No. 4

No. 4 (FAIL)

No. 5

Y

Y

-

-

Y

Y

-

-

-

Y

Y

-

-

-

-

-

-

-

Y

Y

-

-

Y

Y

-

-

-


Data Echo Report

The Data Echo Report echoes the input data for BEAMST together with any input error or warning messages that may result.

Command Summary Report

The Command Summary Report contains details of the type and extent of the post-processing selected. For code checking runs of BEAMST, this report begins with an expanded form of the header and sub-header commands detailing the code checks being performed. For all BEAMST runs the details of the input and output dimensional units, selected loadcases and selected reports are summarized next. Finally any member (‘or joint’) or joint invariant data that is pertinent to the type of post-processing selected is specified. The Command Summary Report contains details of the input and output dimensional units, selected loadcases and selected reports.

Input Data Cross Check Report

The Input Data Cross Check Report presents the input data in an expanded tabular format. This enables the user to quickly validate the data and also enables BEAMST to highlight exactly where any conflicts or data errors occur in the data.

For member calculations a list of sections to be reported is included for all elements selected. By default only the end points and any step positions are reported. Other sections may be requested using the SECT command.

Member Reports

Three member reports are available: Member Properties, Member Forces and Member Stresses. These reports are printed for each selected element in sequential order:

Property - Force - Stress

These reports are not available for joint checks and are optional for all other types.

Member Property Report

The Member Property Report gives all the relevant geometric and material data for each selected member (element). The element number and element group is given at the top of the report along with the units in use. The element’s nodes and coordinates are printed next along with the element’s length and associated effective and unbraced lengths. The slenderness ratio, kℓ/r is also printed.

The cross-section properties are then printed for each step of the element in turn. These consist of the flexural properties (from ASAS or those associated with DESI commands), the material properties (from ASAS and YIEL command) and the section dimensions (from ASAS or DESI command).

Member Force Report

The Member Force Report gives the six components of force at each section for each selected member (element). The element number, its node numbers and group number are given at the top of the report along with the units in use. The forces are then printed for each of the element’s sections for each loadcase in turn. The section positions are identified by number and ratio of position to element length. The first and last sections will be at position 0.00 and 1.00 and relate to the ends of the element. Any intermediate sections are either those specified by a SECT command or at the position of a step change in cross-section properties. The section values are followed by the maximum value found at any section within the element and also the position at which the maximum occurs.

When the SEAR command is in use the maximum may occur at a section position not reported in the section data above. This is because the SEAR command causes additional sections on the element to be searched without reporting.

The final two columns of the Member Force Report give the free moments in the local Y and Z directions.

Member Stress Report

The Member Stress Report gives the member stresses at each section for each selected member (element). The element number, its node numbers and group number are given at the top of the report along with the units in use. The stresses are then printed for each of the element’s sections for each loadcase in turn. The section positions are identified by number and ratio of position to element length. The first and last sections will be at position 0.00 and 1.00 and relate to the ends of the element. Any intermediate sections are either those specified by a SECT command or at the position of a step change in cross-section properties. The section stresses are followed by the maximum stress found at any section within the element and also the position at which the maximum occurs.

When the SEAR command is in use the maximum may occur at a section position not reported in the section data above. This is because the SEAR command causes additional sections on the element to be searched without reporting.

The final four columns of the Member Stress Report give the combined axial stress at four locations on the section denoted A, B, C and D. These locations and the methods of combining the stress are given individually for each section type in Appendix D.

Unity Check Report

A single Unity Check Report is available in BEAMST for each type of Command data block which performs a stress check to a design code and the PRIN parameter UNCK will select it. The report contains member acting stresses where such stresses differ or are not available from the Member Stress Report, allowable stresses and unity checks appropriate to the design code check selected. Messages appropriate to the allowable stresses and unity check(s) which result appear on the right-hand side of the report as a four letter code and are expanded in a Glossary printed at the end of the report. Members ‘(or joints’) or joints which ‘FAIL’ the unity check(s) or violate any design code clause are indicated so in this messages column. All unity check values printed are limited to a maximum of 99.99.

The Unity Check Report for member checks is printed as a separate report for each element selected and if selected together with Member Reports will be printed in the sequential order:

Properties - Force - Stress - Unity Check.

For joint checks, the Unity Check Reports for all selected joints are printed together.

The Unity Check Reports are further explained in the appropriate code check detailed description sections.

Summary Reports

Five types of Unity Check Summary Reports are in general available, examples of which are described in the individual code check sections of this manual. For availability of each type refer to the tables above.

Summary Report number 1 contains the highest yield and buckle combined stress unity checks and their components for each selected element over all loadcases selected.

Summary Report number 2 contains the highest buckle check and all unity checks at the section with the highest yield combined stress unity check for each selected element over all loadcases selected.

Summary Report number 3 contains the highest unity check for each selected loadcase for each element or joint selected.

Summary Report number 4 contains the three worst unity checks for each selected group or joint together with a distribution of unity check values. The distribution is characterized by the number of unity checks exceeding 1.0, the number less than 0.5 and the number in the mid-range. These default ‘exceedence values’ may be altered by the user by the addition of further parameters to the PRIN SUM4 command.

Summary Report number 5 provides information about the highest member forces and moments for each selected group. For each force type (axial, shear, torque and bending) the worst four values are reported together with the element number, loadcase number and position along the element. Separate tables are printed for maximum positive and maximum negative force values. If spectral loadcases have been specified then the maximum and minimum values for each of the force types are determined from the sixteen spectral expansion cases prior to comparing with the forces from other loadcases. A spectral loadcase, therefore, can appear only once for a given element/force type within a group.

If Summary Reports are selected in any Command data block presented to BEAMST, the program will automatically open an additional results file and write the Summary Reports selected to it. This additional output file allows the Summary Reports to be accessed and viewed quicker by the user. The name of the file written to is xxxxBM where xxxx is the fname parameter from the FILES command

For examples of the Unity Check Reports, see the appropriate code check detailed description sections.

Examples

PRIN XCHK PROP STRE SUNI MILLIMETRE KNEWTON
PRIN SUM3 SUM4 1.33 0.5 FAIL SUNI MM KN
PRIN SUM3 BOTH 0.95 SUM4 1.33 0.5 FAIL 0.85 SUNI MM KN

Release 18.2 - © ANSYS, Inc. All rights reserved.