The Mechanical application has a provision that allows you to run structural and thermal problems that are strictly two-dimensional (2D). For models and environments that involve negligible effects from a third dimension, running a 2D simulation can save processing time and conserve machine resources. You can specify a 2D analysis only when you attach a model. Once attached, you cannot change from a 2D analysis to a 3D analysis or vice versa.
You can configure Workbench for a 2D analysis by:
Creating or opening a surface body model in DesignModeler or opening a surface body model in any supported CAD system that has provisions for surface bodies. The model must be in the x-y plane. 2D planar bodies are supported; 2D wire bodies are not.
Then, with the Geometry cell selected in the Project Schematic, expose the properties details of the geometry using the toolbar View drop-down menu, and choose in the Analysis Type drop-down menu (located under Advanced Geometry Options).
Attach the model into the Mechanical application by double-clicking on the Model cell.
A 2D analysis has the following characteristics:
For Geometry object in the tree, the 2D Behavior property has the following options:
(default): Assumes zero stress and non-zero strain in the z direction. Use this option for structures where the z dimension is smaller than the x and y dimensions. Example uses are flat plates subjected to in-plane loading, or thin disks under pressure or centrifugal loading. A Thickness field is also available if you want to enter the thickness of the model.
: Assumes that a 3D model and its loading can be generated by revolving a 2D section 360o about the y-axis. The axis of symmetry must coincide with the global y-axis. The geometry must lie on the positive x-axis of the x-y plane. The y direction is axial, the x direction is radial, and the z direction is in the circumferential (hoop) direction. The hoop displacement is zero. Hoop strains and stresses are usually very significant. Example uses are pressure vessels, straight pipes, and shafts. You may wish to review the Axisymmetric Loads and Reactions section, of the Mechanical APDL Basic Analysis Guide, for a description about how to apply constraints in order to prevent unwanted rigid-body motions.
: Assumes zero strain in the z direction. Use this option for structures where the z dimension is much larger than the x and y dimensions. The stress in the z direction is non-zero. Example uses are long, constant, cross-sectional structures such as structural line bodies. behavior cannot be used in a thermal analysis (steady-state or a transient).
Note: Since thickness is infinite in plane strain calculations, different results (displacements/stresses) will be calculated for extensive loads (that is, forces/heats) if the solution is performed in different unit systems (MKS vs. NMM). Intensive loads (pressure, heat flux) will not give different results. In either case, equilibrium is maintained and thus reactions will not change. This is an expected consequence of applying extensive loads in a plane strain analysis. In such a condition, if you change the Mechanical application unit system after a solve, you should clear the result and solve again.
: Assumes a finite deformation domain length in the z direction, as opposed to the infinite value assumed for the standard option. provides more practical results for deformation problems where a z direction dimension exists, but is not considerable. See Using Generalized Plane Strain for more information.
needs the following three types of data:
: Sets the length of the extrusion.
: Sets the rotation of the extrusion end plane about the x-axis.
: Sets the rotation of the extrusion end plane about the y-axis.
: Enables you to set the (with option), , or options for individual bodies that appear under Geometry in the tree. If you choose , then click an individual body, these 2D options are displayed for the individual body.
For a 2D analysis, use the same procedure for applying loads and supports as you would use in a 3D analysis. The loads and results are in the x-y plane and there is no z component.
You can apply all loads and supports in a 2D analysis except for the following: Line Pressure, Simply Supported, and Fixed Rotation.
A Pressure load can only be applied to an edge.
A Bearing Load and a Cylindrical Support can only be applied to a circular edge.
For analyses involving axisymmetric behavior, Rotational Velocity loads can only be applied about the y-axis.
For loads applied to a circular edge, the direction flipping in the z axis will be ignored.
Only Plain Strain and Axisymmetric are supported for Explicit Dynamics analyses.
Mechanical does not support Cyclic results for a 2D Analysis.