Bearing Load

The Bearing Load boundary condition simulates radial forces only. It is applied on the interior of a cylinder in the radial direction using a coordinate system. If the Mechanical application detects a portion of the load to be in the axial direction, the solver stops the solution and issues an appropriate error message.


Note:  

  • If your CAD system split the target cylinder into two or more faces, select all of the faces when defining the Bearing Load.

  • When analyzing more than one cylinder, be sure that you scope each cylinder with its own Bearing Load boundary condition. Scoping a single Bearing Load to multiple cylinders, as illustrated below, divides the load among the multiple cylindrical faces by area ratio. The example shows two cylinders where the length on the right cylinders is twice the length of the left cylinder. For the single bearing load applied to the two cylinders, the reactions are proportional to each cylinder's area as a fraction of the total load area. This can be seen by the Reaction Force results 100.26N versus 204.33N).

  • Although loading across multiple steps may appear as an application of tabular loading, you cannot set the magnitude of a bearing load in terms of either tabular or functional data. You must set a constant or ramped magnitude for each step such that one value corresponds to each step.


Analysis Types

Bearing Load is available for the following analysis types:

Common Characteristics

This section describes the characteristics of the boundary condition, including the application requirements, support limitations, and loading definitions and values.

Dimensional Types

Geometry Types: Geometry types supported for the Bearing Load boundary condition include:

Topology: The following topology selection options are supported for Bearing Load.

Loading Types: The boundary condition’s loading is defined using one of the following options.

Loading Data Definition : Enter loading data using one of the following options.

Boundary Condition Application

To apply a Bearing Load:

  1. On the Environment context toolbar: click Loads>Bearing Load. Or, right-click the Environment tree object or the Geometry window and select Insert>Bearing Load.

  2. Define the Scoping Method.

  3. Select the method used to define the bearing load: Vector (default) or Components.

  4. Define the Magnitude, Coordinate System directional loading, and/or Direction of the load based on the above selections.

Details View Properties

The selections available in the Details view are described below.

CategoryFields/Options/Description
Scope Scoping Method, options include:
  • Geometry Selection: Default setting, indicating that the boundary condition is applied to a geometry or geometries, which are chosen using a graphical selection tools.

    • Geometry: Visible when the Scoping Method is set to Geometry Selection. Displays the type of geometry (Face, Edge, etc.) and the number of geometric entities (for example: 1 Face, 2 Edges) to which the boundary has been applied using the selection tools.

  • Named Selection: Indicates that the geometry selection is defined by a Named Selection.

    • Named Selection: Visible when the Scoping Method is set to Named Selection. This field provides a drop-down list of available user–defined Named Selections.

Definition

Type: Read-only field that describes the object - Bearing Load.

Define By, options include:

  • Vector: A magnitude and direction (based on selected geometry). Requires the specification of the following inputs:

    • Magnitude

    • Direction

  • Components: Option to define the loading type as Components (in the world coordinate system or local coordinate system, if applied). Requires the specification of at least one of the following inputs:

    • Coordinate System: Drop-down list of available coordinate systems. Global Coordinate System is the default.

    • X Component: Defines magnitude in the X direction.

    • Y Component: Defines magnitude in the Y direction.

    • Z Component: Defines magnitude in the Z direction.

Suppressed: Include (No - default) or exclude (Yes) the boundary condition.

Mechanical APDL References and Notes

The following Mechanical APDL commands, element types, and considerations are applicable for this boundary condition.


Release 18.2 - © ANSYS, Inc. All rights reserved.