The Bearing Load boundary condition simulates radial forces only. It is applied on the interior of a cylinder in the radial direction using a coordinate system. If the Mechanical application detects a portion of the load to be in the axial direction, the solver stops the solution and issues an appropriate error message.
Note:
If your CAD system split the target cylinder into two or more faces, select all of the faces when defining the Bearing Load.
When analyzing more than one cylinder, be sure that you scope each cylinder with its own Bearing Load boundary condition. Scoping a single Bearing Load to multiple cylinders, as illustrated below, divides the load among the multiple cylindrical faces by area ratio. The example shows two cylinders where the length on the right cylinders is twice the length of the left cylinder. For the single bearing load applied to the two cylinders, the reactions are proportional to each cylinder's area as a fraction of the total load area. This can be seen by the Reaction Force results 100.26N versus 204.33N).

Although loading across multiple steps may appear as an application of tabular loading, you cannot set the magnitude of a bearing load in terms of either tabular or functional data. You must set a constant or ramped magnitude for each step such that one value corresponds to each step.
Bearing Load is available for the following analysis types:
This section describes the characteristics of the boundary condition, including the application requirements, support limitations, and loading definitions and values.
Dimensional Types
3D Simulation: Supported. For vector-based loading on a cylindrical face or geometric axis, you define the radial direction by selecting a different piece of geometry on your model that allows you to modify the Direction in the desired direction.
2D Simulation: Supported. The Bearing Load boundary condition applies a variable distribution of force to a circular edge.
Geometry Types: Geometry types supported for the Bearing Load boundary condition include:
Solid: Supported.
Surface/Shell: Not Supported.
Wire Body/Line Body/Beam: Not Supported.
Topology: The following topology selection options are supported for Bearing Load.
Body: Not Supported.
Face: Supported. If the loaded face enlarges (e.g., due to a change in parameters), the total load applied to the face remains constant, but the pressure (force per unit area) decreases.
Edge: Supported - 2D Simulation Only
Vertex: Not Supported.
Nodes: Not Supported.
Loading Types: The boundary condition’s loading is defined using one of the following options.
: Supported. You define the radial direction for your vector load by selecting a piece of geometry on your model that provides the ability to specify the direction correctly.
The vector load definition displays in the Annotation legend with the label Components. The Magnitude and Direction entries, in any combination or sequence, define these displayed values. These are the values sent to the solver.
: Supported. While loads are associative with geometry changes, load direction are not.
Loading Data Definition : Enter loading data using one of the following options.
Constant: Supported.
Tabular (Time Varying): Supported.
Note: Although loading across multiple steps may appear as an application of tabular loading, you cannot set the magnitude of a bearing load in terms of either tabular or functional data. You must set a constant or ramped magnitude for each step such that one value corresponds to each step.
Tabular (Step Varying): Supported for Static Structural analysis only.
Tabular (Spatially Varying): Not Supported.
Function (Time Varying): Not Supported.
Function (Spatially Varying): Not Supported.
To apply a Bearing Load:
On the Environment context toolbar: click Loads>Bearing Load. Or, right-click the Environment tree object or the Geometry window and select Insert>Bearing Load.
Define the Scoping Method.
Select the method used to define the bearing load: Vector (default) or Components.
Define the Magnitude, Coordinate System directional loading, and/or Direction of the load based on the above selections.
The selections available in the Details view are described below.
| Category | Fields/Options/Description |
|---|---|
| Scope |
Scoping Method, options include:
|
| Definition |
Type: Read-only field that describes the object - Bearing Load. Define By, options include:
Suppressed: Include ( - default) or exclude () the boundary condition. |
The following Mechanical APDL commands, element types, and considerations are applicable for this boundary condition.
Force is applied using the SF,,PRES command.
Element types include: