Definition Settings

The differences in the contact settings determine how the contacting bodies can move relative to one another. This category provides the following properties.

Type

Choosing the appropriate contact type depends on the type of problem you are trying to solve. If modeling the ability of bodies to separate or open slightly is important and/or obtaining the stresses very near a contact interface is important, consider using one of the nonlinear contact types (Frictionless, Rough, Frictional), which can model gaps and more accurately model the true area of contact. However, using these contact types usually results in longer solution times and can have possible convergence problems due to the contact nonlinearity. If convergence problems arise or if determining the exact area of contact is critical, consider using a finer mesh (using the Sizing control) on the contact faces or edges.

The available contact types are listed below. Most of the types apply to Contact Regions made up of faces only.


Note:
  • For the Bonded and No Separation contact Type, you can simulate the separation of a Contact Region as it reaches some predefined opening criteria using the Contact Debonding feature.

  • Refer to KEYOPT(12) in the Mechanical APDL Contact Technology Guide for more information about modelling different contact surface behaviors.


Scope Mode

This is a read-only property that displays how the selected Contact Region was generated. Either automatically generated by the application (Automatic) or constructed or modified by the user ( Manual ). Note that this property is not supported for Rigid Body Dynamics analyses.

Behavior

This property will appear only for 3D Face/Face or 2D Edge/Edge contacts. For 3D Edge/Edge or Face/Edge contacts, internally the program will set the contact behavior to Asymmetric (see below). Note that this property is not supported for Rigid Body Dynamics analyses.

Sets contact pair to one of the following:


Note:  Refer to KEYOPT(8) in the Mechanical APDL Contact Technology Guide for more information about asymmetric contact selection.


Trim Contact

The Trim Contact feature can speed up the solution time by reducing the number of contact elements sent to the solver for consideration. Note that this feature is not supported for Rigid Body Dynamics analyses.

Trim Contact options include:

The checking process is performed to identify if there is overlap between the bounding boxes of the elements involved. If the bounding box of an element does not overlap the bounding box of an opposing face or element set, that element is excluded from the solution. Before the elements are checked, the bounding boxes are expanded using the Trim Tolerance property (explained below) so that overlapping can be detected.

Trim Tolerance

This property provides the ability to define the tolerance value that is used to expand the bounding boxes of the elements before the trimming process is performed.

This property is available for both automatic and manual contacts when the Trim Contact is set to On. It is only available for automatic contacts when the Trim Contact is set to Program Controlled since no trimming is performed for manual contacts. For automatic contacts, this property displays the value that was used for contact detection and it is a read-only field. For manual contacts, enter a value greater than zero.

Note that a doubling expansion effect can result from the bounding box expansion since the bounding box of both the source and target elements are expanded. An example of the double expansion effect is illustrated below where the Trim Tolerance is defined as 10 mm. For simplicity sake, the size of the elements is specified as 5mm. Therefore, the bounding boxes for the contact/target elements will extend 10mm (two elements) in each direction as represented by the orange boxes, solid and dashed. For each face, Contact and Target, the number of elements that will be used are illustrated.

The brown area illustrated below represents the elements from the contact face. On the corresponding target side exist potential elements from the entire target face. The elements of the target face that will be kept are drawn in black. On the target Face, each element bounding box is expanded by 10mm and an overlap is sought against each element from the contact side. Referring to the image below, the bounding boxes between Contact Element 1 (CE1) and Target Element 2 (TE2) overlap thus TE2 is included in the analysis. Meanwhile, CE3 and TE4 do not overlap and as a result, TE4 is not included in the analysis. This results in a reduced number of elements in the analysis and, typically, a faster solution.

Suppressed

Specifies whether or not the Contact Region is included in the solution.


Release 18.2 - © ANSYS, Inc. All rights reserved.