Scope Settings

The properties for the Scope category are described in the following table.

Property Description/Selections
Scoping Method Specifies whether the Contact Region is applied to a Geometry Selection (default), a Named Selection , or to a Pre-Generated Interface for fracture mechanics (Interface Delamination) when you are using the ANSYS Composite PrepPost (ACP) application.
Interface This property displays when you select Pre-Generated Interface as the Scoping Method. It provides a drop-down list of the available interface layers that were imported from ACP.

Contact

Displays/selects which geometries (faces, edges, or vertices) or mesh entities (element faces) are considered as contact. The geometries can be manually selected or automatically generated.

For a Face/Edge contact, the edge must be designated as Contact.

A contact pair can have a flexible-rigid scoping, but the flexible side of the pair must always be the Contact side. If the Contact side of the contact pair is scoped to multiple bodies, all of the bodies must have the same Stiffness Behavior, either Rigid or Flexible.

Note that if you click this field, the bodies are highlighted.

Target

Displays which body element (face or edge) or mesh entities (element faces) is considered Target (versus Contact). This element can be manually set or automatically generated.

For Face/Edge contact, the face must be designated as Target.

If the Contact side of the contact pair has a flexible Stiffness Behavior then the Target side can be rigid.

Multiple rigid bodies cannot be selected for the Target side scoping of the contact pair. The selection of multiple rigid bodies for the Target invalidates the Contact Region object and an error message is generated following the solution process.

Note that if you click this field, the bodies are highlighted.

Contact Bodies

This read only property displays which bodies have faces or edges in the Contact list.

Target Bodies

This read only property displays which bodies have faces or edges in the Target list.
Contact Shell Face Specifies whether the Contact should be applied on a surface body’s top face or bottom face. When scoped to an element face, a third option (By Scoping) is also available which applies the contact to the scoped side (top/bottom) of the shell face. If you set Contact Shell Face to the default option, Program Controlled, then the Target Shell Face option must also be set to Program Controlled. The Program Controlled default option is not valid for nonlinear contact types. This option displays only when you scope a surface body to Contact Bodies.
Target Shell Face Specifies whether the Target should be applied on a surface body’s top face or bottom face. When scoped to an element face, a third option (By Scoping) is also available which applies the target to the scoped side (top/bottom) of the shell face. If you set Target Shell Face to the default option, Program Controlled, then the Contact Shell Face option must also be set to Program Controlled. The Program Controlled default option is not valid for nonlinear contact types. This option displays only when you scope a surface body to Target Bodies.

Shell Thickness Effect (See Using KEYOPT(11))

This property appears when the scoping of the contact or target includes a surface body. Options include:

  • Yes - indicates to include the property.

  • No (default) - indicates to exclude the property.

When set to Yes, the contact object becomes under-defined if the Offset Type of any scoped surface body is set to a value other than Middle. In this situation, the following error message will be displayed: "The shell thickness effect of a contact pair is turned on; however, the offset type of a shell body in contact is set to other than Middle. Set its offset type to Middle."

In the presence of a Thickness, Imported Thickness, Layered Section, or an Imported Layered Section object, the following warning message will be issued if a solve is requested: "The shell thickness effect of a contact pair is turned on. Make sure that the offset type of the thickness, imported thickness, layered sections and imported layered sections objects associated with the shell bodies in contact are set to Middle."

Shell Thickness Effect

The Shell Thickness Effect allows users to automatically include the thickness of the surface body during contact calculations. Instead of contact being detected on the face of the surface body, contact will be detected a distance of half the thickness away from the face.

If the surface body undergoes large strains and changes thickness, the updated (current) thickness is also used in the contact calculations. However, to be able to take advantage of this feature, the Offset Type must be set to Middle.

For cases where the user has set Offset Type to Top or Bottom, the user can do the following:


Note:  If the Shell Thickness Effect is activated and the user has specified a contact Offset for the Interface Treatment, the total offset will be half the thickness of the surface body plus the defined contact offset.


Postprocessing surface bodies with the shell thickness effect has the following special considerations:

Support Specifications

Note:
  • All bodies selected for the Target or Contact side of a contact pair must have the same stiffness behavior.

  • You cannot scope the target side in a contact pair to more than one rigid body.

  • If any of the bodies you scope have rigid stiffness behavior, you must select Asymmetric behavior under Definition in the Details view.

  • If you have both rigid and flexible bodies in your contact pair, you must scope the rigid body as a Target.

  • For the Mechanical APDL solver, you cannot scope the Target side in a contact pair to the edge of a rigid body.



Release 18.2 - © ANSYS, Inc. All rights reserved.