Displacements are applied at the geometry level. They require that one or more flat or curved faces or edges or one or more vertices to displace relative to their original location by one or more components of a displacement vector in the world coordinate system or local coordinate system, if applied.
Displacement as a Base Excitation
Displacement can also be defined as a base excitation during a Mode-Superposition Transient analysis or a Mode Superposition Harmonic Response analyses. You scope base excitations to a boundary condition. You can scope multiple base excitations to the same boundary condition, but the base excitations cannot have same direction specified (via the Direction property).
A Displacement is available for the following analysis types:
Note: Full Harmonic Response analyses support non-zero displacements for Component/Components: Real - Imaginary loading types.
This section describes the characteristics of the boundary condition, including the application requirements, support limitations, and loading definitions and values.
Dimensional Types
3D Simulation: Supported. Displaces one or more faces, edges, or vertices.
2D Simulation: Supported. Displaces one or more edge or vertices.
Geometry Types: Geometry types supported for the Displacement boundary condition include:
Solid: Supported.
Surface/Shell: Supported.
Wire Body/Line Body/Beam: Supported.
Topology: The following topology selection options are supported for Displacement.
Body: Supported for rigid bodies in an Explicit Analysis.
Face: Supported.
Non-zero X-, Y-, and Z-components. The face retains its original shape but moves relative to its original location by the specified displacement vector. The enforced displacement of the face causes a model to deform.
For Zero Y-component, no part of the face can move, rotate, or deform in the Y-direction.
For blank (undefined) X- and Z-components, the surface is free to move, rotate, and deform in the XZ plane.
Edge: Supported.
Enforced displacement of an edge is not realistic and leads to singular stresses (that is, stresses that approach infinity near the loaded edge). You should disregard stress and elastic strain values in the vicinity of the loaded edge.
Non-zero X-, Y-, and Z-components. The edge retains its original shape but moves relative to its original location by the specified displacement vector. The enforced displacement of the edge causes a model to deform.
For Zero Y-component, no part of the edge can move, rotate, or deform in the Y-direction.
For blank (undefined) X- and Z-components, the edge is free to move, rotate, and deform in the XZ plane.
Vertex: Supported.
Non-zero X-, Y-, and Z-components. The vertex moves relative to its original location by the specified displacement vector. The enforced displacement of the vertex causes a model to deform.
For Zero Y-component, the vertex cannot move in the Y-direction.
For blank (undefined) X- and Z-components, the vertex is free to move in the XZ plane.
This boundary condition cannot be applied to a vertex scoped to an End Release.
Nodes: Not Supported.
Multiple surfaces, edges, or vertices can be selected.
Avoid using multiple Displacements on the same face/edge/vertex and on faces/edges/vertices having shared faces/edges/vertices.
Loading Types: The boundary condition’s loading is defined using one of the following options.
: Supported.
Entering a zero for a component prevents deformation in that direction.
Entering a blank for a component allows free deformation in that direction.
In a cylindrical coordinate system X, Y, and Z are used for R, Θ, and Z directions. When using a cylindrical coordinate system, non-zero Y displacements are interpreted as translational displacement quantities, ΔY = RΔΘ. Since they are treated as linear displacements it is a reasonable approximation only, for small values of angular motion ΔΘ.
For Explicit Dynamics analyses, when using a cylindrical coordinate system, the Y component (that is, Θ direction) of a displacement constraint is defined as a rotation.
. Supported for Harmonic Response Analysis only. Define direct loading without Phase Angle.
: Supported (3D Faces Only).
. Supported for Harmonic Response Analysis only. Define direct loading without Phase Angle.
. Supported for Displacement as a Base Excitation during Harmonic Response analysis only.
. Supported for Displacement as a Base Excitation during Harmonic Response analysis only.
Loading Data Definition : Enter loading data using one of the following options.
: Supported.
(Time Varying): Supported. (Not supported for Harmonic Response analysis).
Tabular (Step Varying): Supported for Static Structural analysis only.
(Frequency Varying): Supported for Harmonic Response analysis only.
(Spatially Varying): Supported (Not Supported for Explicit Dynamics and Harmonic Response analyses).
(Time Varying): Supported (Not Supported for Harmonic Response analyses).
(Spatially Varying): Supported (Not Supported for Explicit Dynamics and Harmonic Response analyses).
: Supported. (Not Supported for Displacement as a Base Excitation).
To apply a Displacement:
On the Environment context toolbar: click Supports>Displacement. Or, right-click the Environment tree object or the Geometry window and select Insert>Displacement.
Define the Scoping Method.
Select the method used to define the Displacement: Components (default), , Normal To, or .
Define the Coordinate System and displacements or the Distance, of the Displacement based on the above selections.
For Harmonic analyses, specify a Phase Angle as needed.
To apply Displacement as a Base Excitation when the Solver Type property is defined as during a Transient (default setting for a Transient configured to a Modal solution) or a Mode-Superposition Harmonic Response analysis:
In the Definition category of the Details view, set the Base Excitation property to .
The Boundary Condition property provides a drop-down list of the boundary conditions that correspond to the Displacement. Make a selection from this list. Valid boundary condition option for excitations include:
Fixed Support
All Fixed Supports
Displacement
Remote Displacement
Nodal Displacement
Spring: Body-to-Ground
The Absolute Result property is set to by default. As needed, change the value to if you do not want to include enforced motion.
Note: If you apply more than one base excitation (either Displacement or Acceleration), the Absolute Result property needs to have the same setting, either or .
To use complex definition entries, change the Define By property setting to from (default).
Define the loading inputs: Magnitude, Phase Angle (only in MSUP Harmonic Response), and Direction.
Note: You can scope Acceleration or Displacement as a base excitation to the same boundary condition, but the base excitations cannot have same direction specified (via the Direction property).
The selections available in the Details view are described below.
| Category | Fields/Options/Description |
|---|---|
| Scope |
Scoping Method: options include:
Boundary Condition (Displacement as a Base Excitation only): drop-down list of available boundary condition options for application. |
| Definition |
Type: read-only field that describes the object - Displacement. Base Excitation (Displacement as a Base Excitation only): is the default setting. Set to to specify the Displacement as a . Absolute Result (Displacement as a Base Excitation only): This option allows you to include enforced motion with ( - default) or without () base motion. Define By. options include:
Suppressed: include ( - default) or exclude () the boundary condition. |
The following Mechanical APDL commands and considerations are applicable when Displacement is defined as a base excitation in a Mode Superposition Transient analysis or a Mode Superposition Harmonic Response analysis.
Magnitude (constant or tabular) is always represented as a table in the input file.
Base excitation is defined using the D command under the Modal restart analysis (under Modal analysis in case of standalone Harmonic Response analysis).
Base excitation is applied using the DVAL command during a Mode Superposition Transient analysis or Mode Superposition Harmonic Response analysis.
Note: Displacement can be defined as base excitation in a Modal linked Harmonic Response and Modal linked Transient analysis only when the upstream Modal analysis Solver Type is set to (provided program sets solver type internally to or ) or or .