You can apply a Fixed Rotation boundary condition to faces, edges, and vertices of a surface body. When you only apply a fixed rotation support to a surface body, the geometry is free in all translational directions. However, by default, the rotation of the geometry is fixed about the axes of the corresponding coordinate system.
Note:
Rotation constraints are combined with other constraints that produce rotational DOF assignments to determine which values to apply. They are combined with all other constraints to determine the Nodal Coordinate System orientation (frictionless supports, cylindrical supports, given displacements, etc.).
There may be circumstances in which the rotational support and other constraints cannot resolve a discrepancy for preference of a particular node’s coordinate system.
A Fixed Rotation is available for the following analysis types:
The following section outlines the common boundary condition characteristics that include application requirements of the boundary condition, support limitations, as well as loading definitions and values.
Dimensional Types
3D Simulation: Supported.
2D Simulation: Not Supported.
Geometry Types: Geometry types supported for the Fixed Rotation boundary condition include:
Solid: Not Supported.
Surface/Shell: Supported - Surface Body only.
Wire Body/Line Body/Beam: Supported.
Topology: The following topology selection options are supported for Fixed Rotation.
Body: Not Supported.
Face: Supported.
Edge: Supported.
Vertex: Supported.
A fixed vertex rotation support is not realistic and leads to singular stresses (that is, stresses that approach infinity near the fixed vertex rotation support). You should disregard stress and elastic strain values in the vicinity of the fixed vertex rotation support.
This boundary condition cannot be applied to a vertex scoped to an end release.
Nodes: Not Supported.
To apply a Fixed Rotation:
In the Details view, select Free or Fixed for Rotation X, Rotation Y, and Rotation Z to define the fixed rotation support.
On the Environment context toolbar: click Supports>Fixed Rotation. Or, right-click the Environment tree object or the Geometry window and select Insert>Fixed Rotation.
Specify Scoping Method and or .
As needed, specify the coordinate system for the corresponding rotational constraint.
Define the rotational axes as (default) or .
The selections available in the Details view are described below.
| Category | Fields/Options/Description |
|---|---|
| Scope |
Scoping Method - Options include:
|
| Definition |
Type - Read-only field that describes the object - Fixed Rotation. Coordinate System - Drop-down list of available coordinate systems. is the default. Rotation X - (default) or . Rotation Y - (default) or . Rotation Z - (default) or . Suppressed - Include ( - default) or exclude () the boundary condition. Caution: When parameterizing this boundary condition, a axis of rotation is represented by a one (1) and with a value of zero (0) inside the Parameter tab in ANSYS Workbench (outside of Mechanical). Entering any value other than 0 or 1 causes the application to produce unexpected results. |