Hydrostatic Pressure

A hydrostatic pressure load simulates pressure that occurs due to fluid weight.

Analysis Types

Hydrostatic Pressure is available for the following analysis types:

Common Characteristics

This section describes the characteristics of the boundary condition, including the application requirements, support limitations, and loading definitions and values.

Dimensional Types

Geometry Types: Geometry types supported for the Hydrostatic Pressure boundary condition include:

Topology: The following topology selection options are supported for Hydrostatic Pressure.

Loading Types: The boundary condition’s loading is defined using one of the following options.

Loading Data Definition : Hydrostatic Pressure is defined as a constant.


Note:  During a multiple step analysis, tabular data is visible for this boundary condition. This information is read-only but you can use the context menu (right-click) features of the Tabular Data display to activate or deactivate the loading per step.


Boundary Condition Application

To apply a Hydrostatic Pressure:

  1. On the Environment context toolbar: click Loads>Hydrostatic Pressure. Or, right-click the Environment tree object or the Geometry window and select Insert>Hydrostatic Pressure.

  2. Define the Scoping Method. Hydrostatic Pressure can only be scoped to faces.

  3. Select all of the faces that will potentially enclose the fluid.

    Or...

    If you are working with a surface body, specify the Shell Face, defined as the side of the shell (Top or Bottom) on which to apply the hydrostatic pressure load.

  4. Specify the magnitude and direction of the Hydrostatic Acceleration. This is typically the acceleration due to gravity, but can be other acceleration values depending on the modeling scenario. For example, if you were modeling rocket fuel in a rocket’s fuel tank, the fuel might be undergoing a combination of acceleration due to gravity and acceleration due to the rocket accelerating while flying.

  5. Enter the Fluid Density.

  6. Specify the Free Surface Location, defined as the location of the top of the fluid in the container. You can specify this location by using coordinate systems, by entering coordinate values, or by clicking a location on the model.

  7. Mesh the model, then highlight the Hydrostatic Pressure load object to display the pressure contours.

The following example shows the simulation of a hydrostatic pressure load on the wall of an aquarium. Here the wall is modeled as a single surface body. The load is scoped to the bottom side of the face. A fixed support is applied to the bottom edge. Acceleration due to gravity is used and the fluid density is entered as 1000 kg/m3. Coordinates representing the top of the fluid are also entered.

The load plot shown here illustrates the hydrostatic pressure gradient.

Details View Properties

The selections available in the Details view are described below.

CategoryFields/Options/Description
Scope

Scoping Method, options include:

  • Geometry Selection: Default setting, indicating that the boundary condition is applied to a geometry or geometries, which are chosen using a graphical selection tools.

    • Geometry: Visible when the Scoping Method is set to Geometry Selection. Displays the type of geometry (Body, Face, etc.) and the number of geometric entities (for example: 1 Body, 2 Edges) to which the boundary has been applied using the selection tools.

  • Named Selection: Indicates that the geometry selection is defined by a Named Selection.

    • Named Selection: Visible when the Scoping Method is set to Named Selection. This field provides a drop-down list of available user–defined Named Selections.

  • Shell Face

    • Top

    • Bottom

Definition

Type: Read-only field that displays boundary condition type - Hydrostatic Pressure.

Coordinate System: Drop-down list of available coordinate systems. Global Coordinate System is the default.

Suppressed: Include (No - default) or exclude (Yes) the boundary condition.

Fluid Density: Input field for fluid density value.

Hydrostatic Acceleration

Define By, options include:

  • Vector: A magnitude and direction (based on selected geometry). Requires the specification of the following inputs:

    • Magnitude

    • Direction

  • Components

    • X Component

    • Y Component

    • Z Component

Free Surface Location

X Coordinate

Y Coordinate

Z Coordinate

Location: Specify Free Surface Location using geometry picking tools. Valid topologies include: face, edge, vertex.

Mechanical APDL References and Notes

The following Mechanical APDL commands, element types, and considerations are applicable for this boundary condition.


Release 18.2 - © ANSYS, Inc. All rights reserved.