Joint Characteristics

A joint typically serves as a junction where bodies are joined together. Joint types are characterized as fixed or free depending on their rotational and translational degrees of freedom. If you specify a Joint as a Remote Attachment it is classified as a remote boundary condition. Refer to the Remote Boundary Conditions section for a listing of all remote boundary conditions and their characteristics.

Joints are supported in the following structural analyses:


Note:
  • A joint cannot be applied to a vertex scoped to an end release.

  • Each multibody part made of rigid bodies is treated as a single, rigid part. Consequently, joints must not be created within a multibody part.

    Similarly, functionalities such as configure, assemble, model topology, or redundancy analysis always consider each multibody part as a single part, regardless stiffness behavior. Joints must be defined between independent parts or multibody parts to use these functionalities.

  • The Samcef Solver interface supports all joint types except for the fixed joint, slot joint, and the imperfect joints. Only supported joint types are active in the Mechanical interface.

    To maintain consistency with the characteristics of Samcef joints, you must insert a Comment object with the correct name under the joint object. The comment permits you to capture joint properties which are not available in the Properties view in Mechanical. The comment functions similarly to a commands object: the content of the comment is appended to the description of the joint in the solver input file. The necessary name for the comment object is listed for each joint type.


Nature of Joint Degrees of Freedom

Joint Abstraction

Joints are considered as point-to-point in the solution though the user interface shows the actual geometry. Due to this abstraction to a point-to-point joint, geometry interference and overlap between the two parts linked by the joint can be seen during an animation.

Joint Initial Conditions

The degrees of freedom are determined depending on the selected solver. For the ANSYS Rigid Dynamics solver, the degrees of freedom are the relative motion between the parts. For the ANSYS Mechanical solver, the degrees of freedom are the location and orientation of the center of mass of the bodies.

When initial conditions are applied, there are two means for the ANSYS Rigid Dynamics solver to initialize the velocities:

  1. A pure kinematic method, only based on the kinematic constraints. It minimizes the position and velocity increments.

  2. A method using the inertia matrix. The position increment, scaled by the inertia matrix, is minimized; while the velocity increment is calculated in order to minimize the kinetic energy.

Unless otherwise specified using joint conditions, both the ANSYS Mechanical APDL solver and ANSYS Rigid Dynamics solver start with initial velocities equal to zero. This has different implications for each solver. For the ANSYS Mechanical APDL solver, this means that the bodies will be at rest. For the ANSYS Rigid Dynamics solver, this means that the relative velocities will be at rest.

Consider, for example, an in-plane double pendulum, with a constant velocity specified for the first grounded link. The two solvers will treat this scenario as follows:

Joint DOF Zero Value Conventions

Joints can be defined using one or two coordinate systems: the Reference Coordinate System and the Mobile Coordinate System.

The use of two coordinate systems can be beneficial in certain situations, such as when a CAD model is not imported in an assembled configuration. Using two coordinate systems also enables you to employ the Configure and Set features (see Manual Joint Creation), and it gives you the ability to update a model following a CAD update.

For the ANSYS Rigid Dynamics solver, the zero value of the degrees of freedom corresponds to the matching reference coordinate system and moving coordinate system.

If a joint definition includes only the location of the Mobile Coordinate System (see Modifying Joint Coordinate Systems), then the DOF of this joint are initially equal to zero for the geometrical configuration where the joints have been built.

If the Reference Coordinate System is defined using the Override option, then the initial value of the degrees of freedom can be a nonzero value.

Consider the example illustrated below. If a Translational joint is defined between the two parts using two coordinate systems, then the distance along the X axis between the two origins is the joint initial DOF value. For this example, assume the joint initial DOF value is 65 mm.

Conversely, if the joint is defined using a single coordinate as shown below, then the same geometrical configuration has a joint degree of freedom that is equal to zero.

For the ANSYS Mechanical APDL solver, having one or two coordinate systems has no impact. The initial configuration corresponds to the zero value of the degrees of freedom.

Joint Condition Considerations

When applying a Joint Condition, behavior varies depending on the solver selected. The following tables demonstrate variations in solver behavior, using the right part of the translational joint illustrated above moving 100 mm towards the other part over a 1 second period. (The distance along the X axis is 65 mm.)

SolverDisplacement Joint Condition
TimeDisplacement
ANSYS Rigid Dynamics – Two Coordinate Systems065
1165
ANSYS Rigid Dynamics – One Coordinate System00
1100
ANSYS Mechanical APDL – Two Coordinate Systems00
1100
ANSYS Mechanical APDL – One Coordinate System00
1100

You can unify the joint condition input by using a Velocity Joint Condition.

SolverVelocity Joint Condition
TimeDisplacement
ANSYS Rigid Dynamics – Two Coordinate Systems0100
1100
ANSYS Rigid Dynamics – One Coordinate System0100
1100
ANSYS Mechanical APDL – Two Coordinate Systems0100
1100
ANSYS Mechanical APDL – One Coordinate System0100
1100

Release 18.2 - © ANSYS, Inc. All rights reserved.