Bushing Joint

Constrained degrees of freedom:

None

Example:

A Bushing has six degrees of freedom, three translations and three rotations, all of which can potentially be characterized by their rotational and translational degrees of freedom as being free or constrained by stiffness.

For a Bushing, the rotational degrees of freedom are defined as follows:

The three translations and the three rotations form a set of six degrees of freedom. In addition, the bushing behaves, by design, as an imperfect joint, that is, some forces developed in the joint oppose the motion.

The three translational degrees of freedom expressed in the reference coordinate system and the three rotations are expressed as: Ux, Uy, Uz, and Ψ, Θ, φ. The relative velocities in the reference coordinate system are expressed as: Vx, Vy, and Vz. The three components of the relative rotational velocity are expressed as: Ωx, Ωy, and Ωz. Note that these values are not the time derivatives of [Ψ, Θ, φ]. They are a linear combination.

The forces developed in the Bushing are expressed as:

Where:

[F] is force and [T] is Torque, and [K] and [C] are 6x6 matrices (defined using Stiffness Coefficients and Dampening Coefficients options). Off diagonal terms in the matrix are coupling terms between the DOFs.

You can use these joints to introduce flexibility to an over-constrained mechanism. Note that very high stiffness terms introduce high frequencies into the system and may penalize the solution time when using the ANSYS Rigid Dynamics solver. If you want to suppress motion in one direction entirely, it is more efficient to use Joint DOF Zero Value Conventions instead of a very high stiffness.

Scoping:

You can scope a bushing to single or multiple faces, single or multiple edges, or to a single vertex. The scoping can either be from body-to-body or body-to-ground. For body-to-body scoping, there is a reference and mobile side. For body-to-ground scoping, the reference side is assumed to be grounded (fixed), scoping is only available on the mobile side. In addition to setting the scoping (where the bushing attaches to the body), you can set the bushing location on both the mobile and reference side. The bushing reference and mobile location cannot be the same.

Applying a Bushing:

To add a bushing:

  1. After importing the model, highlight the Connections object in the tree.

  2. Choose either Body-Ground>Bushing or Body-Body>Bushing from the toolbar, as applicable.

  3. Highlight the new Bushing object and enter information in the Details view.

Note that matrix data for the Stiffness Coefficients and Dampening Coefficients is entered in the Worksheet. Entries are based on a Full Symmetric matrix.

Non-linear Force Deflection Curve:

A nonlinear force-deflection curve can be used to simulate multi-rate bushing with nonlinear stiffness. A linear piecewise curve is used for this purpose.

To define a nonlinear stiffness-deflection curve:

  1. In the Worksheet, select the cell in which you want to define a non-linear stiffness-deflection curve.

  2. Right-click the cell and then select Constant or Tabular.

  3. Enter a constant stiffness value or enter displacement and stiffness values (minimum of two rows of data) in the Tabular Data window. Tabular entries are plotted in the Graph window and show stiffness vs. displacement.


    Note:  If tabular entries exist in the stiffness matrix, the Mechanical APDL Solver does not account for constant terms and non-diagonal (coupled) terms.


Samcef Solver Comment Object:

BUSHING


Release 18.2 - © ANSYS, Inc. All rights reserved.