For 3D simulations, a line pressure load applies a distributed force using force density loading in units of force per length. You can define force density as a vector, an axial component, or tangentially. Tangential loads can be applied to one edge only whereas vector and component loads and can be applied to one or more edges.

If a pressurized edge enlarges due to a change in CAD parameters, the total load applied to the edge increases, but the pressure (force per unit length) remains constant.
Line Pressure is available for the following analysis types:
This section describes the characteristics of the boundary condition, including the application requirements, support limitations, and loading definitions and values.
Dimensional Types
3D Simulation: Supported.
2D Simulation: Not Supported.
Geometry Types: Geometry types supported for the Line Pressure boundary condition include:
Solid: Supported.
Surface/Shell: Supported.
Wire Body/Line Body/Beam: Supported.
Topology: The following topology selection options are supported for Line Pressure.
Body: Not Supported.
Face: Not Supported.
Edge: Supported.
Vertex: Not Supported.
Nodes: Not Supported.
Loading Types: The boundary condition’s loading is defined using one of the following options.
: Supported.
The vector load definition displays in the Annotation legend with the label Components. The Magnitude and Direction entries, in any combination or sequence, define these displayed values. These are the values sent to the solver.
: Supported (scoped to one edge only).
: Supported.
Loading Data Definition : Enter loading data using one of the following options.
Constant: Supported.
Tabular (Time Varying): Supported.
Tabular (Step Varying): Supported for Static Structural analysis only.
Tabular (Spatially Varying): Supported for Tangential loading only
Function (Time Varying): Supported.
Function (Spatially Varying): Supported for Tangential loading only.
To apply a Line Pressure:
On the Environment context toolbar: click Loads>Line Pressure. Or, right-click the Environment tree object or the Geometry window and select Insert>Line Pressure.
Define the Scoping Method.
Select the method used to define the Line Pressure: Vector (default), Tangential, or Components.
Define the Magnitude, Coordinate System, and/or Direction of the Line Pressure based on the above selections.
For Harmonic analyses, specify a Phase Angle as needed.
The selections available in the Details view are described below.
| Category | Fields/Options/Description |
|---|---|
| Scope |
Scoping Method, options include:
|
| Definition |
Type: Read-only field that displays boundary condition type - Line Pressure. Define By, options include:
Phase Angle (Harmonic Analysis only). Suppressed: Include ( - default) or exclude () the boundary condition. |
The following Mechanical APDL commands, element types, and considerations are applicable for this boundary condition.