This boundary condition distributes a moment "about" (the vector of) an axis across one or more flat or curved faces, or about one or more edges or vertices. Use the right-hand rule to determine the sense of the moment.
A Moment is classified as a remote boundary condition. Refer to the Remote Boundary Conditions section for a listing of all remote boundary conditions and their characteristics.
Moment is available for the following analysis types:
This section describes the characteristics of the boundary condition, including the application requirements, support limitations, and loading definitions and values.
Dimensional Types
3D Simulation: Supported.
2D Simulation: Supported.
Geometry Types: Geometry types supported for the Moment boundary condition include:
Solid: Supported.
Surface/Shell: Supported.
Wire Body/Line Body/Beam: Supported.
Note: Face and edge selections for the moment load can span multiple parts, however, multiple vertex selections must be of the same part type (solid, 3D surface or line bodies) or the selection is ignored.
Topology: The following topology selection options are supported for Moment.
Body: Not Supported.
Face: Supported - 3D only. If a face enlarges (e.g., due to a change in parameters), the total load applied to the face remains constant, but the load per unit area decreases.
Edge: Supported.
Vertex: Supported. This boundary condition cannot be applied to a vertex scoped to an end release.
Nodes: Supported.
Loading Types: The boundary condition’s loading is defined using one of the following options.
– Supported. While loads are associative with geometry changes, load directions are not.
The vector load definition displays in the Annotation legend with the label Components. The Magnitude and Direction entries, in any combination or sequence, define these displayed values. These are the values sent to the solver.
. Supported for Harmonic Response Analysis only.
– Supported.
. Supported for Harmonic Response Analysis only.
Loading Data Definition : Enter loading data using one of the following options.
Constant: Supported.
Tabular (Time Varying): Supported.
Tabular (Step Varying): Supported for Static Structural analysis only.
Tabular (Frequency Varying): Supported for Harmonic Response Analysis only.
By default, at least two frequency entries are required when defining a frequency dependent tabular load.
Tabular (Spatially Varying): Not Supported.
Function (Time Varying): Supported.
Function (Spatially Varying): Not Supported.
To apply a :
On the Environment context toolbar: click Loads>. Or, right-click the Environment tree object or the Geometry window and select Insert>.
Define the Scoping Method.
Note: When specifying the Scoping Method, faces and edges can be scoped to either the geometry where the load is to be applied (Geometry Selection), to a Named Selection, or to a Remote Point . Vertices cannot be scoped to Remote Point.
Select the method used to define the moment: (default), , , or .
Define the Magnitude, Coordinate System directional loading, and/or Direction of the load based on the above selections.
For Harmonic analyses, specify a Phase Angle as needed.
Select the Behavior of the geometry.
As needed, enter a Pinball Region value. The default value is .
The selections available in the Details view are described below.
| Category | Fields/Options/Description |
|---|---|
| Scope |
Scoping Method, options include:
|
| Definition |
Type: Read-only field that displays boundary condition type -
Moment. Define By (3D Only), options include:
(2D Only). Suppressed: Include ( - default) or exclude () the boundary condition. Behavior : This option dictates the behavior of the attached geometry. If the Scope Method property is set to , the boundary condition will then assume the Behavior defined in the referenced Remote Point as well as other related properties. Options include:
Material: This property is available when the Behavior property is set to . Select a material to define material properties for the beams used in the connection. Density is excluded from the material definition. Radius: This property is available when the Behavior property is set to . Specify a radius to define the cross section dimension of the circular beam used for the connection. |
| Advanced | Pinball Region |